Callout tool adds driven
diameter dimensions to holes created by the Hole
Wizard or circular cut features.
Hole callouts are available in drawings. If you change a hole dimension
in the model, the callout updates automatically.
Hole callouts use Hole Wizard information when you create a hole with
the Hole Wizard. The default formats for the Hole Wizard types are stored
A second file, calloutformat_2.txt,
is a simplified version. You can edit either file.
If you want to use the second file, you must rename the file to calloutformat.txt, which is the file
name the SolidWorks software references. You can set the location of the
default folder for Hole Callout Format
File in Tools, Options,
System Options, File Locations.
The number of instances is included
in the hole callout if a hole in a linear or circular pattern was created
in the Hole Wizard. In the JIS standard, you can change the number of
instances indicator to "x" or "-".
Hole callout examples:
A hole callout using information
from the Hole Wizard:
The same hole callout, but defined
A cut feature representing a
hole. The cut feature must contain a circular sketch:
You can add tolerances and precision
to hole callouts:
The axis of the hole must be normal to the
To add hole callouts in a drawing:
Click Hole Callout on the Annotation toolbar, or click Insert, Annotations,
The pointer changes to .
Click the edge of a hole, then click in the graphics area to place
the hole callout.
A Hole Callout is inserted
and the Dimension
PropertyManager appears. The callout contains a diameter symbol
and the dimension of the hole diameter. If the depth
of the hole is known, the callout also contains a depth symbol and the dimension of the depth. If the hole is created in
the Hole Wizard, the callout contains
additional information (the dimensions of a countersink or number of hole
instances, for example).
Edit the callout in the Dimension
You can specify precision, select an arrow style, or add text. However,
you should retain the dimensions and symbols for the size and type of
If the hole has been created
by the Hole Wizard, you can also click Variables
in the Dimension PropertyManager
to access a list of Callout
to insert into the hole callout.
If you attach a hole callout to a tapped
hole in ANSI inch standard and the current drawing units are millimeters,
the drill diameter and hole depths are reported in mm but the thread description
retains the ANSI inch size designation. You might want to replace the
thread description with other variables from the Callout
Variables dialog box.
Repeat steps 2 through 4 to insert additional
hole callouts, then click OK .
display the dimension in various formats by right-clicking the dimension
and clicking Display Options,
then clicking an option: Display as Diameter,
Display as Radius, Display
as Linear, Show Parentheses,
or Show as Inspection.
To edit the properties of a hole callout:
Select the callout and make the changes in the Dimension
If you manually change a portion of the
callout text, you might break that portion's link with the model. SolidWorks
displays a warning message if you are about to break a link.
To modify hole callouts to include
a hole callout.
PropertyManager, select a Tolerance Type
value for Maximum Variation and Minimum Variation
Click OK .
Define by Geometry or Hole Wizard
To toggle between Hole Wizard and geometry definitions:
Right-click the hole callout and select Display Options, Define
To return to the Hole Wizard definition, right-click the hole callout
and select Display Options, Define by Hole Wizard.
These menu items are available only when
holes have been created using the Hole Wizard.
You can change the number of instances indicator to a dash or "x"
for the JIS standard only.
To change the number of instances indicator:
in a text editor. The file is usually located in <install_dir>\solidworks\lang\<language>.
In the file:
At the top of the file, make sure NO-NUMBER-OF-INSTANCES
has an asterisk (*) in front of it.
Search for the JIS section. At the beginning
of the section, set JIS-COUNT-DELIMITER
to a dash or "x":
Save and close the file.
Make sure the calloutformat.txt
file is referenced by the Hole Callout
Format File in File
Manually Define Standards
To manually define derived hole callout standards:
Edit the file calloutformat.txt
or calloutformat_2.txt located
in installation directory\solidworks\lang\<language>\.
Copy and paste the content for ANSI (or any default
standard) to a new section in the text file.
Using only upper case letters, rename the standard
name to your required derived hole callout standard.
Save the file as calloutformat.txt.
Use only upper case letters
to define hole callout standards.
Modify the Hole Callout Format
You can modify the hole callout
format by editing the hole callout format definition file, calloutformat.txt.
Below is an example for editing
Using the code of the symbol
library, you can position symbols and order them in the definition of
each hole wizard type. For example, <MOD-DIAM> creates a diameter
end of the file contains text descriptions of the variables (see the sample
at the right).
Wizard variables are as follows:
To use the definition file, locate the type of hole you want.
Definition of a countersunk through hole:
COUNTERSINK-THRU=<MOD-DIAM> <hw-thruholedia> <hw-thru>;\
<HOLE-SINK><MOD-DIAM> <hw-csdia> X <hw-csang>
Modify the definition.
In this example, the text C'SINK and a space are added before the <MOD-DIAM>
COUNTERSINK-THRU=C'SINK <MOD-DIAM> <hw-thruholedia> <hw-thru>;\
<HOLE-SINK><MOD-DIAM> <hw-csdia> X <hw-csang>
Multi-jog Leaders to Hole Callouts