Assemblies Options
Set assembly options, including options for Large Assembly
Mode.
To customize Assemblies options:
Click Options
(Standard toolbar) or Tools,
Options.
Click Assemblies.
Change the settings, then click OK.
Reset
All returns all
system options, not only those on the active page, to the system defaults.
Assemblies options
Move components
by dragging. Select to allow components to move or rotate within their
degrees of freedom when you drag them in the graphics area. When cleared,
you can still move or rotate a component with the Move
with Triad function or the Move
Component 
and Rotate
Component 
tools (Assembly toolbar).
Prompt before
changing mate alignments on edit. When changes that you make to
mates result in errors that the software can fix by flipping mate alignments,
the software asks if you want it to make the changes. Otherwise, the software
makes the changes automatically (without asking).
Save new components
to external files. If selected, prompts you to name and save new
in-context components to external files. If cleared, saves new in-context
components in the assembly file as virtual
components.
Large assemblies
The selections you make under Large
assemblies apply only when Large Assembly Mode is on. Set options
for normal use (with Large Assembly Mode off) as indicated in the option
descriptions below.
See Large Assembly Mode
for a list of other conditions that are set automatically when Large Assembly
Mode is activated.
Use Large Assembly
Mode to improve performance whenever working with an assembly containing
more than this number of components. Set the number of resolved
components above which Large Assembly Mode automatically activates when
opening or working in an assembly.
When Large Assembly
Mode is active. Select the following options to improve performance:
Do not save
auto recover info. Disables automatic save of your model. (Set
in Backup
Options for normal use.)
Hide all
planes, axes, sketches, curves, annotations, etc. Selects Hide
All Types on the View
menu. When this option is selected, you can override it by clearing Hide All Types on the View
menu, then selecting to show or hide individual types.
Do not display
edges in shaded mode. Turns off edges in shaded mode. If the display
mode of the assembly is Shaded With Edges
, it changes to Shaded
. When this option is selected, you can override it by
clicking Shaded With Edges (View toolbar).
Suspend automatic rebuild. Defers the
update of assemblies, so you can make many changes, then rebuild the assembly
once. Use this option only when absolutely necessary. Rebuild errors created
while this option is active will not become apparent until this option
is deactivated (or you do a manual rebuild), which can make it difficult
to determine the cause of the errors. When this option is selected, you
can override it by right-clicking the assembly name at the top of the
FeatureManager design tree and clearing Suspend Automatic Rebuild.
If you have a 32-bit Windows XP Professional
operating system and are working with very large assemblies, you might
benefit from the /3GB switch.
The switch allows you to allocate more RAM for the SolidWorks application
by decreasing RAM allocated to the operating system. For details, see
Memory
Allocation.