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Combine Bodies

You can combine multiple solid bodies to create a singled-bodied part or another multibody part.

It is strongly recommended that you do not use the Combine feature to combine weldment bodies. It is not always possible to calculate the cut list properties accurately for a body created using the combine feature.

There are three ways to combine multiple solid bodies:

  • Add. Combines solids of all selected bodies to create a single body.

  • Subtract. Removes overlapping material from a selected main body.

  • Common. Removes all material except that which overlaps.

To use the Add or Common operation type:

  1. Click Combine on the Features toolbar, or click Insert, Features, Combine.

    The Combine1 PropertyManager appears.

  2. Under Operation Type, click Add or Common.

  3. Under Bodies to Combine, select the bodies in the graphics area, or select the bodies from the Solid Bodies folder in the FeatureManager design tree.

  4. Click Show Preview to preview the feature.

  5. Click OK .

To use the Subtraction operation type:

  1. Click Combine on the Features toolbar, or click Insert, Features, Combine.

    The Combine1 PropertyManager appears.

  2. Under Operation Type, click Subtract.

  3. Under Main Body, select the body to keep from the graphics area for Solid Body , or select the body from the Solid Bodies folder in the FeatureManager design tree.

  4. Under Bodies to Subtract, select the bodies whose material you want to remove for Solid Bodies .

  5. Click Show Preview to preview the feature.

  6. Click OK .



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