Split and Save Bodies
Use the Split
feature to create multiple
parts from an existing part. You can create separate part files, and form
an assembly from the new parts. You can split a single part document into
a multibody part document.
To split a part:
Click Split on the Features
toolbar, or click Insert, Features, Split.
In the PropertyManager,
set the options:
To split the part using trim tools, select
Trimming Surfaces and click Cut Part.
Split lines appear on the part, showing the
different bodies formed by the split.
Callout boxes appear in the
graphics area for up to 10 bodies at one time. Click Next
10 or Previous 10 to scroll
through all the callout boxes for a part.
Under Resulting Bodies, select the bodies
to save under , or click Auto-assign
All of the saved bodies appear in the graphics
area and are listed in the FeatureManager design tree under Solid Bodies. The
software automatically names all bodies. You can change the names.
Double-click the body name
under File, type a name for the
new part in the dialog box, then click Save.
The new part name appears
in the Resulting Bodies list and
in the callout box. Unsaved bodies are not split and remain with the original
If you clear
the check box for a split part after you save it, that
part is no longer saved as a separate entity. It remains with the original
Click OK .
The new parts are derived; they contain a reference
to the parent part. Each new part contains a single feature named Stock-<parent
You can reattach a derived part to a specified stock part, split feature,
If you change the geometry
of the original part, the new parts also change. If you change the split
feature geometry, no new derived parts are created. The software updates
the existing derived parts, preserving parent-child relations.
With multibody parts, the
various split parts are listed in the FeatureManager design tree under
The original part contains
all its original features plus a new feature called Split.
If you selected Consume
cut bodies under Resulting Bodies,
the solid body displayed in the graphics area is the original solid body
minus the new parts. If all bodies in the original part were saved as
split bodies, no solid body is displayed. To see the original solid body,
move the rollback bar in the FeatureManager design tree above the split
feature or suppress the split feature.
If you delete the split feature
in the original part, the new parts still exist, but the status of the
external reference in the new parts is dangling.
You can also save solid bodies
after you split the model using the Save
Bodies feature. This enables you to save the bodies from a split
part to a different folder or with different names to the same folder.
You can also create an assembly from the split parts.
To save bodies from multibody
Click Insert, Features,
the bodies to save in the graphics area, or under in Resulting Parts.
display the default path, file names, and location of the multibody part.
Under Resulting Parts, double-click each file
name under File to open the Save As dialog box. You can select a
new location and file name for each part. You can also click Auto-assign
Names to select and name all bodies.
an assembly, under Create Assembly,
click Browse, select a folder
to save the assembly as SplitAssembly
type (*.sldasm), and type a file
Click OK .