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Get Features of Multibody Sheet Metal Part Example (VB.NET)

This example shows how to get the number and names of the features in a multibody sheet metal part.

'---------------------------------------------------------------------------

' Preconditions: A multibody sheet metal part is open.

'

' Postconditions: Compare the results printed to the

'                 Immediate window with the bodies and

'                 features in the sheet metal solid bodies folder.

'---------------------------------------------------------------------------

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swconst

Imports System

Imports System.Diagnostics

 

Partial Class SolidWorksMacro

 

    Public Sub main()

 

        Dim swModel As ModelDoc2

        Dim swFeatMgr As FeatureManager

        Dim swFeat As Feature

        Dim swBodyFolder As BodyFolder

        Dim swBody As Body2

        Dim FeatType As String

        Dim FeatTypeName As String

        Dim Bodies As Object

        Dim Features As Object

        Dim i As Long

        Dim j As Long

 

        swModel = swApp.ActiveDoc

        swFeatMgr = swModel.FeatureManager

 

        swFeat = swModel.FirstFeature

        Do While Not swFeat Is Nothing

            FeatType = swFeat.Name

            FeatTypeName = swFeat.GetTypeName2

            Debug.Print("  " & FeatType & " [" & FeatTypeName & "]")

            If FeatTypeName = "SolidBodyFolder" Then

                swBodyFolder = swFeat.GetSpecificFeature2

                Bodies = swBodyFolder.GetBodies

                Debug.Print("    Number of bodies: " & swBodyFolder.GetBodyCount)

                For i = 0 To (swBodyFolder.GetBodyCount - 1)

                    swBody = Bodies(i)

                    Features = swBody.GetFeatures

                    Debug.Print("    Number of features in body #" & i + 1 & ": " & swBody.GetFeatureCount)

                    For j = 0 To (swBody.GetFeatureCount - 1)

                        Debug.Print("       Name of feature: " & Features(j).GetTypeName2)

                    Next j

                Next i

            End If

            swFeat = swFeat.GetNextFeature

        Loop

 

    End Sub

 

    ''' <summary>

    ''' The SldWorks swApp variable is pre-assigned for you.

    ''' </summary>

    Public swApp As SldWorks

 

End Class



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