Hide Table of Contents

Get Reference Point Data Example (VBA)

This example shows how to get reference point data.

 

'------------------------------------------------

'

' Preconditions:

'           (1) Part, assembly, or drawing document is open.

'           (2) Reference point feature is selected.

'

' Postconditions: None

'

'-----------------------------------------------

Option Explicit

Public Enum swRefPointType_e

    swRefPointInvalid = 0

    swRefPointUndefined = 1

    swRefPointAlongCurve = 2

    swRefPointCenterEdge = 3

    swRefPointFaceCenter = 4

    swRefPointFaceVertexProjection = 5

    swRefPointIntersection = 6

End Enum

Public Enum swRefPointAlongCurveType_e

    swRefPointAlongCurveDistance = 0

    swRefPointAlongCurvePercentage = 1

    swRefPointAlongCurveEvenlyDistributed = 2

End Enum

Public Enum swOnSurfacePlaneProjectType_e

    swOnSurfacePlaneProjecttoNearestLocation = 0

    swOnSurfacePlaneProjectAlongSketchNormal = 1

End Enum

Sub main()

    Dim swApp                       As SldWorks.SldWorks

    Dim swModel                     As SldWorks.ModelDoc2

    Dim swSelMgr                    As SldWorks.SelectionMgr

    Dim swFeat                      As SldWorks.feature

    Dim swRefPt                     As SldWorks.refPoint

    Dim swRefPtData                 As SldWorks.RefPointFeatureData

    Dim swMathPt                    As SldWorks.MathPoint

    Dim vEntArr                     As Variant

    Dim vEnt                        As Variant

    Dim swEnt                       As SldWorks.entity

    Dim swSkPt                      As SldWorks.SketchPoint

    Dim swSkSeg                     As SldWorks.SketchSegment

    Dim nStatus                     As Long

    Dim bRet                        As Boolean

    

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    Set swSelMgr = swModel.SelectionManager

    Set swFeat = swSelMgr.GetSelectedObject5(1)

    Set swRefPt = swFeat.GetSpecificFeature2

    Set swRefPtData = swFeat.GetDefinition

    Set swMathPt = swRefPt.GetRefPoint

    

    Debug.Print "File = " & swModel.GetPathName

    Debug.Print "  " & swFeat.Name

    Debug.Print "    Pt = (" & _

            swMathPt.ArrayData(0) * 1000# & ", " & _

            swMathPt.ArrayData(1) * 1000# & ", " & _

            swMathPt.ArrayData(2) * 1000# & ") mm"

    Debug.Print "    AlongCurveOption   = " & swRefPtData.AlongCurveOption

    Debug.Print "    Distance           = " & swRefPtData.distance * 1000# & " mm"

    Debug.Print "    Type               = " & swRefPtData.Type

    bRet = swRefPtData.AccessSelections(swModel, Nothing): Debug.Assert bRet

    

    vEntArr = swRefPtData.Selections

    For Each vEnt In vEntArr

        ' Returns NULL entries if in assembly

        If Not Nothing Is vEnt Then

            If TypeOf vEnt Is SldWorks.entity Then

                Set swEnt = vEnt

                

                bRet = swEnt.Select4(True, Nothing): Debug.Assert bRet

            ElseIf TypeOf vEnt Is SldWorks.SketchPoint Then

                Set swSkPt = vEnt

                

                bRet = swSkPt.Select4(True, Nothing): Debug.Assert bRet

            ElseIf TypeOf vEnt Is SldWorks.SketchSegment Then

                Set swSkSeg = vEnt

                

                bRet = swSkSeg.Select4(True, Nothing): Debug.Assert bRet

            Else

                Debug.Assert False

            End If

        End If

    Next

    swRefPtData.ReleaseSelectionAccess

End Sub

'-----------------------------------------------------



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Get Reference Point Data Example (VBA)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2010 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.