Hide Table of Contents

Suppress Component Feature Example (VBA)

This example shows how to suppress the selected component feature.

 

'------------------------------------------------

'

' Preconditions:

'       (1) Assembly document is open.

'       (2) Component feature is selected in the FeatureManager design tree.

'

' Postconditions: Selected component feature is suppressed.

'

' NOTE: Editing a component requires that geometry on

'       the component to be selected.  However, not

'       all features are associated with geometry.

'       Therefore, it is necessary to select the component

'       before attempting to edit the component.

'

'------------------------------------------------

Option Explicit

Public Enum swDocumentTypes_e

    swDocNONE = 0       ' Used to be TYPE_NONE

    swDocPART = 1       ' Used to be TYPE_PART

    swDocASSEMBLY = 2   ' Used to be TYPE_ASSEMBLY

    swDocDRAWING = 3    ' Used to be TYPE_DRAWING

End Enum

'  Possible status values for AssemblyDoc::EditPart2

Public Enum swEditPartCommandStatus_e

    swEditPartFailure = -1

    swEditPartAsmMustBeSaved = -2

    swEditPartCompMustBeSelected = -3

    swEditPartCompMustBeResolved = -4

    swEditPartCompMustHaveWriteAccess = -5

    swEditPartSuccessful = 0

    swEditPartCompNotPositioned = &H1

End Enum

Sub main()

    Dim swApp               As SldWorks.SldWorks

    Dim swModel             As SldWorks.ModelDoc2

    Dim swAssy              As SldWorks.AssemblyDoc

    Dim swEditModel         As SldWorks.ModelDoc2

    Dim swEditPart          As SldWorks.PartDoc

    Dim swEditAssy          As SldWorks.AssemblyDoc

    Dim swSelMgr            As SldWorks.SelectionMgr

    Dim swFeat              As SldWorks.feature

    Dim swComp              As SldWorks.Component2

    Dim sFeatName           As String

    Dim nStatus             As Long

    Dim nInfo               As Long

    Dim i                   As Long

    Dim bRet                As Boolean

    

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    Set swAssy = swModel

    Set swSelMgr = swModel.SelectionManager

    Set swFeat = swSelMgr.GetSelectedObject5(1): Debug.Assert Not swFeat Is Nothing

    Set swComp = swSelMgr.GetSelectedObjectsComponent2(1): Debug.Assert Not swComp Is Nothing

    

    Debug.Print "File = " & swModel.GetPathName

    Debug.Print "    " & swFeat.Name & " <" & swFeat.GetTypeName & ">"

    Debug.Print ""

    

    sFeatName = swFeat.Name

    

    bRet = swComp.Select2(False, 0): Debug.Assert bRet

    nStatus = swAssy.EditPart2(True, False, nInfo): Debug.Assert swEditPartSuccessful = nStatus

    

    Set swEditModel = swAssy.GetEditTarget

    

    Select Case swEditModel.GetType

        Case swDocPART

            Set swEditPart = swEditModel

            Set swFeat = swEditPart.FeatureByName(sFeatName): Debug.Assert Not swFeat Is Nothing

            

            bRet = swFeat.Select2(False, 0): Debug.Assert bRet

        

        Case swDocASSEMBLY

            Set swEditAssy = swEditModel

            Set swFeat = swEditAssy.FeatureByName(sFeatName): Debug.Assert Not swFeat Is Nothing

            

            bRet = swFeat.Select2(False, 0): Debug.Assert bRet

            

        Case Else

            Debug.Assert False

    End Select

        

    ' Try to suppress the selected feature;

    ' should not assert because feature might not be

    ' able to be suppressed; for example, standard reference plane or

    ' origin

    bRet = swEditModel.EditSuppress2: Debug.Assert bRet

    swAssy.EditAssembly

End Sub

'------------------------------------------



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Suppress Component Feature Example (VBA)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2010 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.