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Get DimXpert Feature Example (VBA)

This example builds a part to demonstrate usage of the DimXpert API for the following DimXpert features:

 

    *  Cylinder

    *  Fillet

    *  Plane

    *  Slot

    *  Pattern

'-------------------------------------------------

' Preconditions:

' 1. Open <SolidWorks_install_dir>\samples\tutorial\api\cover_plate.sldprt.

' 2. Open the DimXpert toolbar from View > Toolbars.

' 3. Click the Auto Dimension Scheme icon in the DimXpert toolbar.

' 4. Ensure that all feature filters are selected.

' 5. Click the green check mark to accept the settings.

' 6. Observe the following DimXpert features on the DimXpertManager tab:

'    Cylinder, Fillet, Plane, Slot, Slot Pattern.

' 7. Open an Immediate window in the IDE.

' 8. Ensure that the latest SolidWorks DimXpert type library is loaded

'    in Tools > References.

' 9. Step through this macro (F8) and compare the output in the

'    Immediate Window with the features displayed in DimXpertManager.

'

' Postconditions: Compare the output in the Immediate Window with the features

' displayed on the DimXpertManager tab of the Management Panel.

' NOTE: Because this part is used in a SolidWorks online tutorial,

' do not save any changes when you close it.

'--------------------------------------------------

Option Explicit

 

Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swModelDocExt As SldWorks.ModelDocExtension

Dim swSelMgr As SldWorks.SelectionMgr

Dim swConfig As SldWorks.Configuration

Dim swFeature As SldWorks.feature

Dim swAnn As SldWorks.feature

Dim swSchema As SldWorks.DimXpertManager

Dim swDXPart As DimXpertPart

Dim featureType As swDimXpertFeatureType_e

Dim features As Variant

Dim appliedFeatures As Variant

Dim appliedAnnotations As Variant

Dim appliedAnnotation As DimXpertAnnotation

Dim feature As DimXpertFeature

Dim appliedFeature As DimXpertFeature

Dim msgStr As String

Dim msgStr2 As String

Dim msgStr3 As String

Dim msgStr4 As String

Dim n As Long

Dim o As Long

Dim p As Long

Dim boolstatus As Boolean

Sub main()

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    

    Set swModelDocExt = swModel.Extension

    Set swSelMgr = swModel.SelectionManager

    

    ' Get the default DimXpert schema using IModelDocExtension.DimXpertManager()

    Set swSchema = swModelDocExt.DimXpertManager("Default", True)

    

    ' Get IDimXpertPart from the IDimXpertManager

    Set swDXPart = swSchema.DimXpertPart

    

    Dim featCount As Long

    featCount = swDXPart.GetFeatureCount

    msgStr = "Total of "

    msgStr2 = featCount

    msgStr = msgStr + msgStr2 + " features in " + (swSchema.SchemaName)

    Debug.Print ""

    Debug.Print msgStr

    

    ' Get IDimXpert features through IDimXpertPart

    features = swDXPart.GetFeatures

    

    msgStr = (swSchema.SchemaName) + " has the following features: "

    Debug.Print ""

    Debug.Print msgStr

    For n = 0 To UBound(features)

        'Use IDimXpertFeature to get feature data

        Set feature = features(n)

        Debug.Print "  " + "Feature name: " + (feature.Name)

        

        featureType = feature.Type

        Call GetPatternType(featureType, msgStr2)

        

        msgStr = "     Feature type "

        msgStr3 = " is suppressed on the DimXpertManager tab? "

        msgStr4 = feature.IsSuppressed()

        Debug.Print msgStr + msgStr2 + msgStr3 + msgStr4

        

        msgStr = "     " + "Swift model: "

 

        'Use IFeature to get the Swift model corresponding to this geometric dimensioning and tolerancing data

        Set swFeature = feature.GetModelFeature()

        If Not (swFeature Is Nothing) Then

            msgStr2 = swFeature.GetTypeName2()

            Debug.Print msgStr + msgStr2

        End If

        

        msgStr = "     " + "Number of SolidWorks face entities in this feature: "

        msgStr2 = feature.GetFaceCount

        Debug.Print msgStr + msgStr2

        

        msgStr = "     " + "Number of applied features: "

        msgStr2 = feature.GetAppliedFeatureCount()

        Debug.Print msgStr + msgStr2

        

        appliedFeatures = feature.GetAppliedFeatures()

        If Not (IsEmpty(appliedFeatures)) Then

            For o = 0 To UBound(appliedFeatures)

                Set appliedFeature = appliedFeatures(o)

                Debug.Print "        " + "Applied feature name: " + (appliedFeature.Name)

            Next

        End If

        

        msgStr = "     " + "Number of applied annotations: "

        msgStr2 = feature.GetAppliedAnnotationCount()

        Debug.Print msgStr + msgStr2

        

        appliedAnnotations = feature.GetAppliedAnnotations()

        If Not (IsEmpty(appliedAnnotations)) Then

            For p = 0 To UBound(appliedAnnotations)

                Set appliedAnnotation = appliedAnnotations(p)

                Debug.Print "        " + "Applied annotation name: " + (appliedAnnotation.Name)

            Next

        End If

        

        Debug.Print "     "

    Next

    

    ' If you know the name of a DimXpert feature, you can get it directly using IDimXpertPart.GetFeature("name"),

    ' which can return a general IDimXpertFeature or a more specific interface on the feature

    

    Dim cylinderFeature As IDimXpertCylinderFeature

    Set cylinderFeature = swDXPart.GetFeature("Cylinder1")

    msgStr = cylinderFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

        

    ' Get the nominal top plane coordinates for Cylinder1

    

    Dim x As Double

    Dim y As Double

    Dim z As Double

    Dim i As Double

    Dim j As Double

    Dim k As Double

    boolstatus = cylinderFeature.GetNominalTopPlane(x, y, z, i, j, k)

    msgStr = "X-coordinate of nominal top plane of " + cylinderFeature.Name + " is "

    msgStr2 = x

    Debug.Print msgStr + msgStr2

    

    ' Get the thread for the cylinder, if it exists

    

    Dim isThreaded As Boolean

    Dim threadDesignation As String

    Dim threadDepth As Double

    boolstatus = cylinderFeature.GetThread(isThreaded, threadDesignation, threadDepth)

    msgStr = "The cylinder is threaded? "

    msgStr2 = isThreaded

    Debug.Print msgStr + msgStr2

    Debug.Print ""

    

    ' Get the radius of Fillet1

    

    Dim filletFeature As IDimXpertFilletFeature

    Set filletFeature = swDXPart.GetFeature("Fillet1")

    msgStr = filletFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

    Dim radius As Double

    radius = filletFeature.radius

    msgStr = "The fillet radius is "

    msgStr2 = radius

    Debug.Print msgStr + msgStr2

     

    Dim planeFeature As IDimXpertPlaneFeature

    Set planeFeature = swDXPart.GetFeature("Plane1")

    msgStr = planeFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

        

    ' Get the nominal top plane coordinates for Plane1

    

    boolstatus = planeFeature.GetNominalPlane(x, y, z, i, j, k)

    msgStr = "X-coordinate of nominal top plane of " + planeFeature.Name + " is "

    msgStr2 = x

    Debug.Print msgStr + msgStr2

        

    ' Get the nominal closed slot width for Slot1

    

    Dim slotFeature As IDimXpertCompoundClosedSlot3DFeature

    Set slotFeature = swDXPart.GetFeature("Slot1")

    msgStr = slotFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

    Dim width As Double

    Dim length As Double

    Dim longitudeI As Double

    Dim longitudeJ As Double

    Dim longitudeK As Double

    boolstatus = slotFeature.GetNominalClosedSlot(width, length, x, y, z, i, j, k, longitudeI, longitudeJ, longitudeK)

    msgStr = "Width of nominal closed slot is "

    msgStr2 = width

    Debug.Print msgStr + msgStr2

        

    ' Get the sub-features of Slot Pattern1

    

    Dim patternFeature As IDimXpertPatternFeature

    Set patternFeature = swDXPart.GetFeature("Slot Pattern1")

    msgStr = patternFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

        

    featureType = patternFeature.PatternType

    Call GetPatternType(featureType, msgStr2)

    

    Dim featureCount As Integer

    featureCount = patternFeature.GetSubFeatureCount()

    msgStr = "     Number of "

    msgStr3 = featureCount

    Debug.Print msgStr + msgStr2 + " is " + msgStr3

    

    Dim subfeatures As Variant

    subfeatures = patternFeature.GetSubFeatures()

    Debug.Print "     Sub-features of Slot Pattern1:"

    For n = 0 To UBound(subfeatures)

        ' Use IDimXpertCompoundClosedSlot3DFeature to get the two planes of the slot

        ' The names of the planes are inherited from the Name property of the parent interface, IDimXpertFeature

        Set slotFeature = subfeatures(n)

        Debug.Print "        " + slotFeature.Name

        Dim plane1 As IDimXpertPlaneFeature

        Dim plane2 As IDimXpertPlaneFeature

        boolstatus = slotFeature.GetPlaneFeatures(plane1, plane2)

        Debug.Print "          " + plane1.Name

        Debug.Print "          " + plane2.Name

    Next

End Sub

Public Sub GetPatternType(ByRef featureType, ByRef msgStr2)

    If (featureType = swDimXpertFeature_Plane) Then

            msgStr2 = "Plane"

    ElseIf (featureType = swDimXpertFeature_Cylinder) Then

            msgStr2 = "Cylinder"

    ElseIf (featureType = swDimXpertFeature_Cone) Then

            msgStr2 = "Cone"

    ElseIf (featureType = swDimXpertFeature_Extrude) Then

            msgStr2 = "Extrude"

    ElseIf (featureType = swDimXpertFeature_Fillet) Then

            msgStr2 = "Fillet"

    ElseIf (featureType = swDimXpertFeature_Chamfer) Then

            msgStr2 = "Chamfer"

    ElseIf (featureType = swDimXpertFeature_CompoundHole) Then

            msgStr2 = "CompoundHole"

    ElseIf (featureType = swDimXpertFeature_CompoundWidth) Then

            msgStr2 = "CompoundWidth"

    ElseIf (featureType = swDimXpertFeature_CompoundNotch) Then

            msgStr2 = "CompoundNotch"

    ElseIf (featureType = swDimXpertFeature_CompoundClosedSlot3D) Then

            msgStr2 = "CompoundClosedSlot3D"

    ElseIf (featureType = swDimXpertFeature_IntersectPoint) Then

            msgStr2 = "IntersectPoint"

    ElseIf (featureType = swDimXpertFeature_IntersectLine) Then

            msgStr2 = "IntersectLine"

    ElseIf (featureType = swDimXpertFeature_IntersectCircle) Then

            msgStr2 = "IntersectCircle"

    ElseIf (featureType = swDimXpertFeature_IntersectPlane) Then

            msgStr2 = "IntersectPlane"

    ElseIf (featureType = swDimXpertFeature_Pattern) Then

            msgStr2 = "Pattern"

ElseIf (featureType = swDimXpertFeature_Sphere) Then

            msgStr2 = "Sphere"

ElseIf (featureType = swDimXpertFeature_BestfitPlane) Then

            msgStr2 = "Bestfit plane"

ElseIf (featureType = swDimXpertFeature_Surface) Then

            msgStr2 = "Surface"

    End If

    

End Sub



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