You can create one or more curves in a sketch by projecting an edge,
loop, face, curve, or external sketch contour, set of edges, or set of
sketch curves onto the sketch plane.
To convert an entity:
In an open sketch, click a model edge, loop, face,
curve, external sketch contour, set of edges, or set of curves.
You can also click an entity
after clicking the Convert Entities
Select a face to convert the edges of the face.
Select a face, then select an edge of a loop. The software
selects only the loop.
Select contiguous faces to get an entire outline of the
faces. The line segments correspond to each face.
Click Convert Entities (Sketch toolbar) or Tools,
The following relations are created:
On Edge . Created between
the new sketch curve and the entity, which causes the curve to update
if the entity changes.
Fixed. Created internally on the endpoints
of the sketch entity so the sketch remains in a "fully defined"
state. This internal relation is not displayed when you use Display/Delete
Relations. Remove the Fixed relation
by dragging the endpoints.
are creating a component or feature in the context of an
assembly and Do
not create references external to the model is selected in Tools, Options,
References, then the
sketch relations described above are not
created. See Controlling
Creation of External References.
In the PropertyManager, click Select
chain to convert all contiguous sketch entities.