Hide Table of Contents

Convert Entities

You can create one or more curves in a sketch by projecting an edge, loop, face, curve, or external sketch contour, set of edges, or set of sketch curves onto the sketch plane.

To convert an entity:

  1. In an open sketch, click a model edge, loop, face, curve, external sketch contour, set of edges, or set of curves.

You can also click an entity after clicking the Convert Entities art\CEDGETOL.gif tool.

Examples:

Select a face to convert the edges of the face.

Select a face, then select an edge of a loop. The software selects only the loop.

Select contiguous faces to get an entire outline of the faces. The line segments correspond to each face.

  1. Click Convert Entities art\CEDGETOL.gif (Sketch toolbar) or Tools, Sketch Tools, Convert Entities.

    The following relations are created:

    • On Edge . Created between the new sketch curve and the entity, which causes the curve to update if the entity changes.

    • Fixed. Created internally on the endpoints of the sketch entity so the sketch remains in a "fully defined" state. This internal relation is not displayed when you use Display/Delete Relations. Remove the Fixed relation by dragging the endpoints.

If you are creating a component or feature in the context of an assembly and Do not create references external to the model is selected in Tools, Options, External References, then the sketch relations described above are not created. See Controlling Creation of External References.

  1. In the PropertyManager, click Select chain to convert all contiguous sketch entities.

  2. Click .

Related Topics

Offset Entities

Silhouettes

 



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Convert Entities
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:

x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: SOLIDWORKS 2010 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.