Configuring Bolt Patterns in Smart Fasteners
Smart Fasteners added to hole
patterns use a bolt pattern derived from the hole pattern. The fasteners
are all the same and there is only one fastener listed in the Smart
Fasteners PropertyManager. If you want to change the properties
of some bolts in the pattern, (for example, make them longer), you can
specify different configurations of the bolt.
Each time you specify a Smart Fastener,
you add it to your Toolbox database.
Smart Fasteners follows the Files options in the SolidWorks Toolbox
Toolbox - User Settings dialog
box to determine if fasteners are added to an assembly as a configuration
of an existing part or as a copy of an existing part. For information
about configuring Toolbox, see Toolbox
Help.
To change the parameters of an individual fastener in
a pattern:
Click 
to expand the Smart
Fastener in the FeatureManager design tree.
-
Click to expand the DerivedLPattern
(or DerivedCPattern).
All fasteners in the pattern are listed.
-
Right-click one or more fasteners in the list and select Component
Properties.
The Component Properties
dialog box appears.
Under Referenced configuration, select Use named configuration.
-
Select a bolt from the list.
NOTE:
If you do not see the configuration you want, you can add a new configuration
to the Toolbox
database using the procedure below.
-
Click OK.
The revised bolt appears.
To add a new fastener configuration to the Toolbox database:
Click to expand the Smart
Fastener in the FeatureManager design tree.
Right-click the fastener component and select
Edit Toolbox Definition.
In the PropertyManager, select new parameters
for the fastener. For example, choose a different length or drive type.
-
Click 
.
The selected instance of the fastener changes to the new configuration.