Mirror Feature
Creates a copy of a feature, (or multiple features), mirrored about
a face or a plane. You can select the feature or you can select the faces
that comprise the feature.
Bodies to Mirror.
Select a body in a single model or multibody part to create a mirror entity.
Multibody
parts. Apply features to one or more multibody
parts
by selecting Geometry Pattern
and using Feature Scope to choose
which bodies should include the feature.
You must create the model
to which you want to add the features for multibody parts prior to adding
those features.
If you modify the original feature (),
the mirrored copy is updated to reflect the changes.
To mirror a feature:
Click Mirror
on the Features toolbar or Insert,
Pattern/Mirror, Mirror.
-
Under Mirror Face/Plane
, select a face or a plane in the graphics area.
You can select features, the faces that comprise features, or a
body with multibody parts.
To use features: Under Features
to Mirror , click one or more features in the model
or use the flyout in the FeatureManager design tree.
-
To mirror the entire model: Under Bodies
to Mirror , select a model in the graphics area.
The mirrored model attaches to the face you select.
To use faces: Under Faces
to Mirror , in the graphics area click the faces
that comprise the feature you want to mirror. Faces
to Mirror is useful with imported parts where the
import process included the faces of the feature, but not the feature
itself.
To mirror
a pattern on multibody parts:
Under
Features to Mirror , select the pattern from the FeatureManager design tree.
Under
Options, select Geometry
pattern.
Under
Feature Scope,
specify which bodies you want the feature to affect.
If you select Bodies
to Mirror, the following Options
appear:
Merge solids.
When you select a face on a solid part, and clear the Merge
solids check box, you can create a mirrored body that is attached
to the original body, but is a separate entity. If you select Merge
solids, the original part and the mirrored part become a single
entity.
-
Knit surfaces. If you select
to mirror a surface by attaching the mirror face to the original face
without intersections or gaps between the surfaces, you can select Knit surfaces to knit the two surfaces
together.
-
If you want to mirror only the geometry (faces and edges) of the
features, rather than solving the whole feature, select
.
The geometry pattern option speeds up the creation and rebuilding of the
pattern. However, you cannot create geometry patterns of features that
have faces merged with the rest of the part. To
mirror a feature pattern on multibody parts, you must select Geometry
Pattern.
The geometry pattern is only available with Features
to Mirror and Faces to Mirror.
To mirror the visual properties of the mirrored
entities (SolidWorks colors, textures, and cosmetic thread data), select
Propagate Visual Properties.
Click OK .
Related Topics
Mirror
Entities
Mirror
Part