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Simple Hole PropertyManager

The Simple Hole PropertyManager appears when you create a new Simple Hole in a part, or when you edit an existing simple hole feature. The PropertyManager controls the following properties:


Sets the starting condition for the simple hole feature.

  • Sketch Plane. Starts the simple hole from the same plane on which the sketch is located.

  • Surface/Face/Plane. Starts the simple hole from one of these entities. Select a valid entity for Surface/Face/Plane

  • Vertex. Starts the simple hole from the vertex you select for Vertex .

  • Offset. Starts the simple hole on an plane that is offset from the current sketch plane. Set the offset distance for Enter Offset Value.

Direction 1

  • End Condition. Select from these End Condition types.

  • Direction of Extrusion . Extrudes the hole in a direction other than normal to the profile of the sketch.

Normal to sketch extrusion

Direction vector extrusion

  • Face/Plane . Select a face or plane in the graphics area to set the hole depth when you choose Up To Surface or Offset From Surface as the End Condition.

  • Offset Distance . Set the hole depth or offset distance when you choose Blind or Offset From Surface as the End Condition.

    • Reverse offset. Applies the specified Offset Distance in the opposite direction from the selected Face/Plane .

    • Translate surface. Applies the specified Offset Distance relative to the selected surface or plane. To use a true offset, clear Translate surface.

  • Vertex . Select a vertex or midpoint in the graphics area to set the hole depth when you select Up To Vertex as the End Condition.

  • Hole Diameter .

  • Draft On/Off . Adds draft to the hole. Set Draft Angle to specify the degrees for the draft.

    • Draft Outward. Creates an outward draft angle when you select Draft On/Off .

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