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Lofted Bend

Lofted bends in sheet metal parts use two open-profile sketches that are connected by a loft. The Base-Flange feature is not used with the Lofted Bend feature.

Characteristics of lofted bends:

  • Cannot be mirrored.

  • Require two sketches that include:

    • Open profiles without sharp edges.

    • Aligned profile openings to ensure flat pattern accuracy.

    • Profile segments in each sketch are the same type.

    • Sketch profiles are on parallel planes.

To create a lofted bend:

  1. Create two separate open profile sketches.

  2. Click Lofted Bend (Sheet Metal toolbar) or click Insert, Sheet Metal, Lofted Bends.

  1. In the graphics area, select both sketches. For each profile, select the point from which you want the path of the loft to travel.

    In the PropertyManager, under Profiles , the sketch names appear.

  1. Examine the path preview. Click Move Up or Move Down to adjust the order of the profiles, or re-select the sketches to connect different points on the profiles.

  2. Set a value for Thickness.

  3. Click Reverse Direction , if necessary.

  1. Under Bend Line Control select:

    • Number of bend lines and set a value for Setting to control coarseness of the flat pattern bend lines.

    • Maximum deviation and set a value.

Decreasing the value of Maximum deviation increases the number of bend lines.

of bend lines

  1. Click OK .



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