Dimension Value PropertyManager
In the Dimension Value PropertyManager, you can specify the display of dimensions. If you select multiple dimensions, only the properties that apply to all the selected dimensions are available.
Dimension Assist Tools
Allows you to dimension a drawing with smart or DimXpert (for drawings) dimensioning. Click DimXpert 
to access the DimXpert (for drawings) and Autodimension tabs.
Smart dimensioning 
. Lets you create dimensions with the Smart Dimension
tool.
Rapid dimensioning 
. Lets you enable or disable the rapid dimension manipulator. Select to enable; clear to disable. This setting persists across sessions.
DimXpert
. Lets you apply dimensions to fully define manufacturing features (patterns, slots, pockets, fillets, etc.) and locating dimensions, using DimXpert for drawings
.
Tolerance/Precision
Callout value. Choose a value in the currently selected dimension. This is available for dimensions with multiple values in the callout.
Tolerance Type 
. Select from the list. Selections available depend on the type of dimension.
Maximum Variation 
.
Minimum Variation 
.
Unit Precision 
. Select the number of digits after the decimal point from the list for the dimension value.
Tolerance Precision 
. Select the number of digits after the decimal point for tolerance values.
Configurations. (Parts and assemblies only) Applies the dimension tolerance to specific configurations for driven dimensions only.
Classification 
. (Fit, Fit with tolerance, or Fit (tolerance only)) When you select either Hole Fit or Shaft Fit (below), the list for the other category (Hole Fit or Shaft Fit) is filtered based on the classification.
Hole Fit 
and Shaft Fit 
. (Fit, Fit with tolerance, or Fit (tolerance only)) Select from the lists, or type any text.
NOTE: Bilateral tolerances (Maximum Variation and Minimum Variation) are available in the Fit with tolerance or Fit (tolerance only) type if you specify Hole Fit or Shaft Fit, but not both.
Fit tolerance display. (Fit, Fit with tolerance, or Fit (tolerance only))
Stacked with line display.
Stacked without line display.
Linear display.
Show parentheses. Parentheses are available for Bilateral, Symmetric, and Fit with tolerance tolerance types. Parentheses are available for Fit with tolerance if you specify Hole Fit or Shaft Fit, but not both.
2nd Tolerance/Precision
Available for chamfer dimensions.
Primary Value
Primary Value is displayed for driving dimensions and can be changed to alter the model. You can override the dimension value. For dimensions that are not referenced, you can change the dimension name. Driven (reference) dimensions list a value and name, but you cannot change them.
Name. The name of the selected dimension.
Dimension value. The value of the selected dimension.
Override value. Select to override the primary value, and type a new value. If you clear Override value, the dimension returns to its original value but retains the tolerance. Override values do not automatically update when geometry changes.
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Original value
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Overridden value
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Reverse Direction 
. Change the dimension direction between positive and negative sense.
Dimension Text
Text. The dimension appears automatically in the center text box, represented by <DIM>. Place the pointer anywhere in the text box to insert text. If you delete <DIM>, you can reinsert the value by clicking Add Value 
.
For some types of dimensions, additional text appears automatically. For example, a Hole Callout for a counterbore hole displays the diameter and depth of the hole (<MOD-DIAM><DIM><HOLE-DEPTH>xx).
Hole Callouts
for holes created in the Hole Wizard display information from the Hole Wizard. You can edit the text and insert variables from the
Callout Variables
dialog box.
Justify. You can justify text horizontally and, for some standards, you can justify the leader vertically.
Symbols. Click to place the pointer where you want a standard symbol. Click a symbol icon or click More to access the
.
Chamfer Dimension Display.
Distance X Distance.
Distance X Angle.
Angle X Distance.
C Distance. Available only for chamfers with 45° angles.
Dual Dimension
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Specifies that the dimension is displayed in both the document's unit system and the dual dimension units. Both units are specified in Document Properties - Units. You set where the alternate units are displayed in Document Properties - Dimensions. Dual dimensions are displayed in brackets.
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Unit Precision . Select the number of digits after the decimal point from the list for the dimension value.
Tolerance Precision  . Select the number of digits after the decimal point for tolerance values.
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