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Dome
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Dome

You can create one or more dome features simultaneously on the same model. The Parameters in the dome PropertyManager include:

  • Faces to Dome . Select one or more planar or non-planar faces.

you can apply domes to faces whose centroid lies outside the face. This allows you to apply domes to irregularly shaped contours .

  • Distance. Set a value for the distance by which the dome expands.

  • Reverse Direction . Click to create a concave dome (default is convex).

  • Constraint Point or Sketch . Control the dome feature by selecting a sketch that contains points to constrain the shape of the sketch. When you use a sketch containing points as a constraint, the Distance is disabled.

  • Direction. Click Direction , and select a direction vector from the graphics area to extrude the dome in a direction other than normal to the face. As a direction vector, you can use a linear edge or the vector created by two sketch points.

  • Elliptical dome. Specify an elliptical dome for cylindrical or conical models. An elliptical dome's shape is a half ellipsoid, with a height equal to one of the ellipsoid radii.

  • Continuous dome. Specify a continuous dome for polygonal models. A continuous dome's shape slopes upwards, evenly on all sides. If you clear Continuous dome, the shape rises normal to the edges of the polygon.  

Continuous dome is not available for four-sided polygons or when you use a Constraint Point or Sketch or a Direction vector.

  • Show preview. Check for a preview.

  On cylindrical and conical models, you can set Distance to 0. The software calculates the distance using the radius of the arc as a basis for the dome. It creates a dome that is tangent to the adjacent cylindrical or conical face.

To create a dome:

  1. Click Dome on the Features toolbar, or click Insert, Features, Dome.

  2. In the PropertyManager, under Parameters, follow the guidelines listed above.

  3. Click OK .



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