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Large Assembly Mode

Large Assembly Mode is a collection of system settings that improves the performance of assemblies. You can turn on Large Assembly Mode at any time, or you can set a threshold for the number of components, and have Large Assembly Mode turn on automatically when that threshold is reached.

While using the Open dialog box to open an assembly whose number of components exceeds the specified threshold, Mode is automatically set to Large Assembly Mode, but you can select another mode from the list.

You specify the threshold on the Assemblies page in System Options. In addition, you can specify the following Large Assembly Mode options there. See Assemblies Options for details.

  • Do not save auto recover info

  • Hide all planes, axes, sketches, curves, annotations, etc.

  • Do not display edges in shaded mode

  • Suspend automatic rebuild

To turn on Large Assembly Mode:

Click Large Assembly Mode (Assembly toolbar) or Tools, Large Assembly Mode.

Large Assembly Mode appears on the status bar.

To turn off Large Assembly Mode:

Click to clear Large Assembly Mode (Assembly toolbar) or Tools, Large Assembly Mode.

When Large Assembly Mode is on, the following options become unavailable (grayed out) on their respective System Options page or toolbar, and are automatically set as described below. When Large Assembly Mode is turned off, the options return to their previous settings.

System Options page
or
Toolbar

Option

Status when
Large Assembly Mode is on

Drawings

Show contents while dragging drawing view

Off. Only the view boundary is shown while dragging a drawing view.

Smooth dynamic motion of drawing views

Off. Dynamic operations to drawings, such as panning and zooming, do not display smoothly.

Automatically hide components on view creation

On. Any components of an assembly not visible in a new drawing view are hidden and listed on the Hide/Show Components tab of the Drawing View Properties dialog box.

Drawings - Display Style

Display style for new views

Hidden lines removed is set as the default display style for new views.

Display quality for new views

Draft quality. Only minimum model information is loaded into memory. Some edges may appear to be missing, and print quality may be slightly degraded.

Display/Selection

Dynamic highlight from graphics view

Off. Model faces, edges, and vertices are not highlighted when you move the pointer over a sketch, model, or drawing.

Anti-alias edges

Off. Jagged edges in Shaded With Edges, Wireframe, Hidden Lines Removed, and Hidden Lines Visible modes are not smoothed out.

Assembly transparency for in context edit

Maintain assembly transparency. Components not being edited retain their individual transparency settings.

FeatureManager

Dynamic highlight

Off. The geometry in the graphics area (edges, faces, planes, axes, and so on) is not highlighted when the pointer passes over the item in the FeatureManager design tree.

Performance

Transparency

High quality for normal view mode. While the part or assembly is not moving or rotating, the transparency is high quality. When moved or rotated with the pan or rotate tools, the application switches to low-quality transparency, enabling you to rotate the model faster.

Curvature generation

Only on demand. Initial curvature display is slower, but uses less memory.

Level of detail

Minimum. The level of detail is minimal during dynamic view operations (zoom, pan, and rotate) in assemblies, multi-body parts, and draft views in drawings.

Check out-of-date lightweight components

Don't Check. Loads assemblies without checking for out-of-date lightweight components.

Update mass properties while saving document

Off. Does not recalculate the mass properties on save. The next time you access the mass properties, the system will need to recalculate them.

View toolbar and menu

Shadows in Shaded Mode

Off.

RealView Graphics

Off.

Related Topics

AssemblyXpert

Large Assembly Settings

Simplifying Large Assemblies

Simplified Representations of Assemblies

Suspending Automatic Rebuilds

 



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