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Insert Sketch Text and Hole Example (VBA)

This example shows how to insert sketch text and a hole at the selected point on a face.

 

'-----------------------------------------------

'

' Preconditions: A model document is open and a face is selected.

'

' Postconditions: The specified text and a hole are created on the

'                 face at the point of selection.

'

'-----------------------------------------------

Option Explicit

 

Dim swApp As SldWorks.SldWorks

Dim swPart As SldWorks.PartDoc

Dim swModel As SldWorks.ModelDoc2

Dim swSelMgr As SldWorks.SelectionMgr

Dim eTapLocations(9) As Variant

Dim boolstatus As Boolean

 

Function TransformPoint(ByVal Sketch1 As Sketch, ByVal X As Double, ByVal Y As Double, ByVal Z As Double) As Variant

    Dim ptArr(2) As Double

    ptArr(0) = X

    ptArr(1) = Y

    ptArr(2) = Z

    

    Dim NewPt As Variant

    Dim swMathUtil As SldWorks.MathUtility

    Set swMathUtil = swApp.GetMathUtility

    

    Dim swMathPt As SldWorks.MathPoint

    Set swMathPt = swMathUtil.CreatePoint((ptArr))

    

    Dim params As Variant

    params = swMathPt.ArrayData

    Dim swMathTrans As SldWorks.MathTransform

    Set swMathTrans = Sketch1.ModelToSketchTransform

    Set swMathPt = swMathPt.MultiplyTransform(swMathTrans)

    NewPt = swMathPt.ArrayData()

    TransformPoint = NewPt

End Function

    

    

Sub main()

 

    Set swApp = Application.SldWorks

    Set swPart = swApp.ActiveDoc

    Set swModel = swApp.ActiveDoc

    

    Set swSelMgr = swPart.SelectionManager

    

Dim selFace As Face2

Dim selEnt As Entity

Dim selPt As Variant

Set selFace = swSelMgr.GetSelectedObject6(1, -1)

 

Set selEnt = selFace

selPt = swSelMgr.GetSelectionPoint2(1, -1)

Dim selData As SldWorks.SelectData

Set selData = swSelMgr.CreateSelectData

selData.X = selPt(0)

selData.Y = selPt(1)

selData.Z = selPt(2)

 

Dim swSketchMgr As SldWorks.SketchManager

Set swSketchMgr = swModel.SketchManager

swSketchMgr .InsertSketch True

selPt = TransformPoint(swModel.IGetActiveSketch2, selPt(0), selPt(1), selPt(2))

 

Dim skText As SketchText

Set skText = swModel.InsertSketchText(selPt(0), selPt(1), selPt(2), "Hole", 0, 0, 0, 100, 100)

 

Dim params As Variant

params = skText.GetCoordinates

 

swSketchMgr.InsertSketch True

 

boolstatus = selEnt.Select4(False, selData)

 

Dim holeFeat As SldWorks.Feature

Dim swFeatMgr As SldWorks.FeatureManager

Set swFeatMgr = swModel.FeatureManager

Set holeFeat = swFeatMgr.SimpleHole(0.001, True, False, False, 0, 0, 0.001, 0.001, False, False, False, False, 0, 0, False, False, False, False, 1, 1)

 

End Sub



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