> InsertRevolvedRefSurface Method (IFeatureManager)
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InsertRevolvedRefSurface Method (IFeatureManager)

Creates a revolved reference surface by revolving a profile around a centerline.

.NET Syntax

Visual Basic (Declaration) 
Function InsertRevolvedRefSurface( _
   ByVal Angle As Double, _
   ByVal ReverseDir As Boolean, _
   ByVal Angle2 As Double, _
   ByVal RevType As Integer _
) As Feature
Visual Basic (Usage) 
Dim instance As IFeatureManager
Dim Angle As Double
Dim ReverseDir As Boolean
Dim Angle2 As Double
Dim RevType As Integer
Dim value As Feature
 
value = instance.InsertRevolvedRefSurface(Angle, ReverseDir, Angle2, RevType)
C# 
Feature InsertRevolvedRefSurface( 
   double Angle,
   bool ReverseDir,
   double Angle2,
   int RevType
)
C++/CLI 
Feature^ InsertRevolvedRefSurface( 
&   double Angle,
&   bool ReverseDir,
&   double Angle2,
&   int RevType
)

Parameters

Angle
Angle of revolution in radians
ReverseDir

Angle is positive or negative (True or false)

Angle2

Angle of revolution in radians

RevType

Type of revolution (see Remarks)

Return Value

Pointer to IFeature object

Remarks

Make the selections using IModelDocExtension::SelectByID2 before calling this method. See the SolidWorks Help for information about what entities are valid for selection.

 

The RevType argument can be one of these values:

  • 0 = One direction revolution. 

  • 1 = MidPlane revolution. For this type of revolve, the angle specification specifies the full revolution. The angle to revolve is (angle/2) on either side of the sketch. The ReverseDir argument has no effect. 

  • 2 = Two direction revolution. For a two direction revolve, Angle is the angle to revolve in Direction1 and Angle2 is the angle to revolve in Direction2.

This method does not support 3D sketches.

 

See Also

Availability

SolidWorks 2007 FCS, Revision Number 15.0


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Web Help Content Version: API Help (English only) 2012 SP05

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