Hide Table of Contents

Insert Structural Weldment Example (C#)

This example shows how to create structural weldment features using structural member groups.

// --------------------------------------------------------------------------
// Preconditions:
// 1. Verify existence of the weldment profile pathname
//    as specified in both InsertStructuralWeldment4 method calls in this macro.
// 2. Ensure this macro's namespace matches your C# project name.
// 3. Open an Immediate Window.
//
// Postconditions:
// 1. Weldment, Structural Member1, and Structural Member2

//    are in the FeatureManager design tree.
// 2. Structural Member1 group is rotated 45 degrees.
// 3. Inspect the Immediate Window for more information.
//---------------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
using System.Diagnostics;
namespace InsertStructuralWeldment_CSharp.csproj
{
    
partial class SolidWorksMacro
    {

        
ModelDoc2 Part;
        
bool boolstatus;
        
FeatureManager FeatMgr;
        
SelectionMgr SelMgr;
        
Feature swWeldFeat;
        
StructuralMemberFeatureData swWeldFeatData;

        
public void Main()
        {

            
string MacroFolder = null;
            MacroFolder = swApp.GetCurrentMacroPathFolder();
            swApp.SetCurrentWorkingDirectory(MacroFolder);

            
string Template = null;
            Template = swApp.GetUserPreferenceStringValue((
int)swUserPreferenceStringValue_e.swDefaultTemplatePart);
            Part = (
ModelDoc2)swApp.NewDocument(Template, 0, 0, 0);

            FeatMgr = Part.FeatureManager;
            SelMgr = (
SelectionMgr)Part.SelectionManager;

            Part.ClearSelection2(
true);

            
object vSkLines = null;
            vSkLines = Part.SketchManager.CreateCornerRectangle(-0.1872393706766, 0.1133237194389, 0, -0.07003610048208, 0.009188409684237, 0);

            Part.ClearSelection2(
true);

            vSkLines = Part.SketchManager.CreateCornerRectangle(0.06513561531715, 0.03369083550887, 0, 0.1807053904567, -0.08106219210316, 0);
            Part.SketchManager.InsertSketch(
true);

            Part.ViewZoomtofit2();

            
object myFeature = null;
            myFeature = Part.FeatureManager.InsertWeldmentFeature();

            
StructuralMemberGroup Group1 = default(StructuralMemberGroup);
            Group1 = FeatMgr.CreateStructuralMemberGroup();
            
SketchSegment[] segments1 = new SketchSegment[2];
            
StructuralMemberGroup[] GroupArray1 = new StructuralMemberGroup[1];

            boolstatus = Part.Extension.SelectByID2(
"Line1@Sketch1", "EXTSKETCHSEGMENT", -0.1495427140733, 0.1133237194389, 0, false, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2(
"Line2@Sketch1", "EXTSKETCHSEGMENT", -0.1872393706766, 0.08238014634844, 0, true, 0, null, 0);

            segments1[0] = (
SketchSegment)SelMgr.GetSelectedObject6(1, 0);
            segments1[1] = (
SketchSegment)SelMgr.GetSelectedObject6(2, 0);

            Group1.Segments = segments1;
            Group1.Angle = 0.785714285714286;
            
//radians
            Group1.ApplyCornerTreatment = true;
            Group1.CornerTreatmentType = (
int)swSolidworksWeldmentEndCondOptions_e.swEndConditionMiter;
            Group1.MirrorProfile =
true;
            Group1.MirrorProfileAxis = (
int)swMirrorProfileOrAlignmentAxis_e.swMirrorProfileOrAlignmentAxis_Vertical;
            Group1.GapWithinGroup = 0.0127;
            
//meters

            GroupArray1[0] = Group1;

            myFeature = Part.FeatureManager.InsertStructuralWeldment4(
"C:\\Program Files\\SolidWorks Corp\\SolidWorks\\data\\weldment profiles\\ansi inch\\c channel\\3 x 5.sldlfp", 1, false, GroupArray1);

            Part.ClearSelection2(
true);

            
StructuralMemberGroup Group2 = default(StructuralMemberGroup);
            Group2 = FeatMgr.CreateStructuralMemberGroup();
            
SketchSegment[] segments2 = new SketchSegment[2];
            
StructuralMemberGroup[] GroupArray2 = new StructuralMemberGroup[1];

            boolstatus = Part.Extension.SelectByID2(
"Line5@Sketch1", "EXTSKETCHSEGMENT", 0.1185825251083, 0.03369083550887, 0, false, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2(
"Line6@Sketch1", "EXTSKETCHSEGMENT", 0.06513561531715, -0.02774616865332, 0, true, 0, null, 0);

            segments2[0] = (
SketchSegment)SelMgr.GetSelectedObject6(1, 0);
            segments2[1] = (
SketchSegment)SelMgr.GetSelectedObject6(2, 0);

            Group2.Segments = segments2;
            Group2.AlignAxis = (
int)swMirrorProfileOrAlignmentAxis_e.swMirrorProfileOrAlignmentAxis_Vertical;

            GroupArray2[0] = Group2;

            myFeature = Part.FeatureManager.InsertStructuralWeldment4(
"C:\\Program Files\\SolidWorks Corp\\SolidWorks\\data\\weldment profiles\\ansi inch\\c channel\\3 x 5.sldlfp", 1, false, GroupArray2);

            Part.ClearSelection2(
true);

            
// Get Group Information

            StructuralMemberGroup Group = default(StructuralMemberGroup);
            
object[] vGroups = null;
            
object[] vSegments = null;

            boolstatus = Part.Extension.SelectByID2(
"Structural Member1", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swWeldFeat = (
Feature)SelMgr.GetSelectedObject6(1, 0);

            swWeldFeatData = (
StructuralMemberFeatureData)swWeldFeat.GetDefinition();
            swWeldFeatData.AccessSelections(Part,
null);

            
Debug.Print("");
            
Debug.Print("Groups Count : " + swWeldFeatData.GetGroupsCount());
            
Debug.Print(" Feature Name : " + swWeldFeat.Name);

            vGroups = (
object[])swWeldFeatData.Groups;

            
int i = 0;
            
int j = 0;
            
for (i = vGroups.GetLowerBound(0); i <= vGroups.GetUpperBound(0); i++)
            {
                Group = (
StructuralMemberGroup)vGroups[i];
                
Debug.Print(" Segment Count in Group " + i + 1 + " : " + Group.GetSegmentsCount());
                
Debug.Print(" Rotational angle of group: " + Group.Angle);
                
Debug.Print(" ApplyCornerTreatment: " + Group.ApplyCornerTreatment);
                
Debug.Print(" CornerTreatmentType: " + Group.CornerTreatmentType);
                
Debug.Print(" MirrorProfile: " + Group.MirrorProfile);
                
Debug.Print(" MirrorProfileAxis: " + Group.MirrorProfileAxis);
                
Debug.Print(" GapWithinGroup: " + Group.GapWithinGroup);
                vSegments = (
object[])Group.Segments;
                
for (j = vSegments.GetLowerBound(0); j <= vSegments.GetUpperBound(0); j++)
                {
                    ((
SketchSegment)vSegments[j]).Select(false);
                }
            }

            swWeldFeatData.ReleaseSelectionAccess();

            boolstatus = Part.Extension.SelectByID2(
"Structural Member2", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swWeldFeat = (
Feature)SelMgr.GetSelectedObject6(1, 0);
            swWeldFeatData = (
StructuralMemberFeatureData)swWeldFeat.GetDefinition();
            swWeldFeatData.AccessSelections(Part,
null);

            
Debug.Print("");
            
Debug.Print("Groups Count : " + swWeldFeatData.GetGroupsCount());
            
Debug.Print(" Feature Name : " + swWeldFeat.Name);

            vGroups = (
object[])swWeldFeatData.Groups;
            
for (i = vGroups.GetLowerBound(0); i <= vGroups.GetUpperBound(0); i++)
            {
                Group = (
StructuralMemberGroup)vGroups[i];
                
Debug.Print(" Segment Count in Group " + i + 1 + " : " + Group.GetSegmentsCount());
                
Debug.Print(" Rotational angle of group: " + Group.Angle);
                
Debug.Print(" ApplyCornerTreatment: " + Group.ApplyCornerTreatment);
                
Debug.Print(" CornerTreatmentType: " + Group.CornerTreatmentType);
                
Debug.Print(" MirrorProfile: " + Group.MirrorProfile);
                
Debug.Print(" MirrorProfileAxis: " + Group.MirrorProfileAxis);
                
Debug.Print(" GapWithinGroup: " + Group.GapWithinGroup);
                vSegments = (
object[])Group.Segments;
                
for (j = vSegments.GetLowerBound(0); j <= vSegments.GetUpperBound(0); j++)
                {
                    ((
SketchSegment)vSegments[j]).Select(false);
                }
            }

            swWeldFeatData.ReleaseSelectionAccess();

            Part.ClearSelection2(
true);
        }

        
public SldWorks swApp;

    }
}



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Insert Structural Weldment Example (C#)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2012 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.