Remove Edge from Edge Flange Feature Example (VBA)
This example shows how to remove from edge in an edge flange feature in a sheet
metal part.
'----------------------------------------------------------------------------
' Preconditions:
' 1. Open:
' install_dir\samples\tutorial\api\SM1-remove-edges.sldprt
' 2. Open the Immediate window.
'
' Postconditions:
' 1. One edge is removed from Edge-Flange1.
' 2. Verify by examining the output printed to the Immediate window.
'
' NOTE: Because the model is used elsewhere,
' do not save changes when closing it.
' ---------------------------------------------------------------------------
Option Explicit
Sub Main()
Dim swApp As SldWorks.SldWorks
Dim swDocument As SldWorks.PartDoc
Dim swSelectionManager As SldWorks.SelectionMgr
Dim swEdgeFlangeData As SldWorks.EdgeFlangeFeatureData
Dim swFeature As SldWorks.Feature
Dim lNumEdges As Long
Dim aEdgesToRemove() As SldWorks.Edge
Dim lIdx As Long
Dim bStatus As Boolean
Dim lNumEdgesToRemove As Long
Dim vEdgesToRemove As Variant
Dim vEdges As Variant
Dim nStatus As SwConst.swEdgeFlangeError_e
Set swApp = Application.SldWorks
Set swDocument = swApp.ActiveDoc
Set swSelectionManager = swDocument.SelectionManager
bStatus = swDocument.Extension.SelectByID2("Edge-Flange1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
Set swFeature = swSelectionManager.GetSelectedObject6(1, 0)
swDocument.ClearSelection2 True
Set swEdgeFlangeData = swFeature.GetDefinition
swEdgeFlangeData.AccessSelections swDocument, Nothing
vEdges = swEdgeFlangeData.Edges
lNumEdges = UBound(vEdges) - LBound(vEdges) + 1
Debug.Print "Number of edges in edge flange = " & lNumEdges
'
' Select number of edges to remove
'
Select Case (1)
Case 1
' Remove one edge
lNumEdgesToRemove = 1
Case 2
' Remove all edges
lNumEdgesToRemove = lNumEdges
Case 3
' Remove no edges
lNumEdgesToRemove = 0
End Select
vEdgesToRemove = Empty
If (lNumEdgesToRemove >= 1) Then
ReDim aEdgesToRemove(lNumEdgesToRemove - 1)
For lIdx = 0 To (lNumEdgesToRemove - 1)
Set aEdgesToRemove(lIdx) = vEdges(lIdx)
Next lIdx
vEdgesToRemove = aEdgesToRemove
End If
nStatus = swEdgeFlangeData.RemoveEdges(vEdgesToRemove)
Debug.Print "Edge removal error code = " & swEdgeFlangeError2String(nStatus)
bStatus = swFeature.ModifyDefinition(swEdgeFlangeData, swDocument, Nothing)
Debug.Print "Status of modify definition = " & bStatus
swEdgeFlangeData.AccessSelections swDocument, Nothing
vEdges = Empty
vEdges = swEdgeFlangeData.Edges
If (Not IsEmpty(vEdges)) Then
lNumEdges = UBound(vEdges) - LBound(vEdges) + 1
Debug.Print "Number of edges in edge flange = " & lNumEdges
Else
Debug.Print "Number of edges in edge flange = 0"
End If
swEdgeFlangeData.ReleaseSelectionAccess
End Sub
Private Function swEdgeFlangeError2String(ByVal nStatus As SwConst.swEdgeFlangeError_e) As String
Select Case (nStatus)
Case 0
swEdgeFlangeError2String = "no error"
Case swEdgeFlangeError_e.swEdgeFlangeError_EdgeAlreadyExists
swEdgeFlangeError2String = "edge already exists"
Case swEdgeFlangeError_e.swEdgeFlangeError_EdgeNotSpecified
swEdgeFlangeError2String = "edge not specified"
Case swEdgeFlangeError_e.swEdgeFlangeError_NumberOfEdgesAndSketchesNotEqual
swEdgeFlangeError2String = "number mismatch"
Case swEdgeFlangeError_e.swEdgeFlangeError_SketchNotSpecified
swEdgeFlangeError2String = "sketch not specified"
Case Else
swEdgeFlangeError2String = "unknown error"
End Select
End Function