Function InsertCutBlend( _
   ByVal Closed As Boolean, _
   ByVal KeepTangency As Boolean, _
   ByVal ForceNonRational As Boolean, _
   ByVal TessToleranceFactor As Double, _
   ByVal StartMatchingType As Short, _
   ByVal EndMatchingType As Short, _
   ByVal IsThinBody As Boolean, _
   ByVal Thickness1 As Double, _
   ByVal Thickness2 As Double, _
   ByVal ThinType As Short, _
   ByVal UseFeatScope As Boolean, _
   ByVal UseAutoSelect As Boolean _
) As Feature

Dim instance As IFeatureManager
Dim Closed As Boolean
Dim KeepTangency As Boolean
Dim ForceNonRational As Boolean
Dim TessToleranceFactor As Double
Dim StartMatchingType As Short
Dim EndMatchingType As Short
Dim IsThinBody As Boolean
Dim Thickness1 As Double
Dim Thickness2 As Double
Dim ThinType As Short
Dim UseFeatScope As Boolean
Dim UseAutoSelect As Boolean
Dim value As Feature
 
value = instance.InsertCutBlend(Closed, KeepTangency, ForceNonRational, TessToleranceFactor, StartMatchingType, EndMatchingType, IsThinBody, Thickness1, Thickness2, ThinType, UseFeatScope, UseAutoSelect)

Feature InsertCutBlend( 
   bool Closed,
   bool KeepTangency,
   bool ForceNonRational,
   double TessToleranceFactor,
   short StartMatchingType,
   short EndMatchingType,
   bool IsThinBody,
   double Thickness1,
   double Thickness2,
   short ThinType,
   bool UseFeatScope,
   bool UseAutoSelect
)

Feature^ InsertCutBlend( 
&   bool Closed,
&   bool KeepTangency,
&   bool ForceNonRational,
&   double TessToleranceFactor,
&   short StartMatchingType,
&   short EndMatchingType,
&   bool IsThinBody,
&   double Thickness1,
&   double Thickness2,
&   short ThinType,
&   bool UseFeatScope,
&   bool UseAutoSelect
) 

Parameters

Closed

True if you want the loft to be closed, false to leave it open (see Remarks)

KeepTangency

Controls whether the section curves are tangent (see Remarks)

ForceNonRational

True to force the resulting surface to be non-rational; false to not

TessToleranceFactor

A factor to control the number of intermediate sections used for loft with centerline;
the default value is 1.0; the greater the variable, the more intermediate sections
are created

StartMatchingType

Tangency type at the start profile (see Remarks)

EndMatchingType

Tangency type at the end profile (see Remarks)

IsThinBody

True if this feature is a thin body, false is not

Thickness1

Thickness value for the first direction

Thickness2

Thickness value for the second direction

ThinType

Thin wall type:

• 0 = One direction
• 1 = One direction reverse
• 2 = Mid-plane
• 3 = Two direction

UseFeatScope

True if the feature only affects selected bodies, false if the feature affects all
bodies

UseAutoSelect

True to automatically select all bodies and have the feature affect those bodies,
false to select the bodies the feature affects (see Remarks)

Return Value

Selection of guide curves and centerline is optional; however, selection of the profiles must be in an order consistent with the desired direction of the loft.

Use of guide curves is strongly recommended, especially when selection of profiles is done in the FeatureManager design tree.

You can use any number of profiles; however, if you selected only one profile, then any selected guide curves must be closed curves.

If Closed is True and you selected less that three profiles, then any selected guide curves must be closed curves.

If the section curves are tangent, then KeepTangency controls whether the resulting surfaces are also be tangent. Specify True to maintain the tangency as seen in the section curves; false to not. When generating tangent surfaces, SolidWorks maintains planar and cylindrical surface shapes if the section curves exhibit these characteristics.

Use IModelDocExtension::SelectById2 to select the profiles and guide curves. The mark for the profile selections should be 1; the mark for any guide curve selection, if provided, should be a 2; the mark for the centerline selection, if provided, should be a 4; the mark for the start tangency vector selection, if provided, should be a 8; the mark for the start tangency faces selection, if provided, should be a 16 (not available); the mark for the end tangency vector selection, if provided, should be a 32; the mark for the end tangency faces selection, if provided, should be a 64 (not available); linear edge, sketch line, axis, plane and planar faces are qualified for tangency vector sections.

The tangency type arguments can take the following values:

• 0 - none

• 1 - tangent to the normal of the profile

• 2 - tangent to a selected vector

• 3 - tangency to all the adjacent faces sharing an edge with the start profile

• 4 - tangent to some of the selected faces sharing an edge with the start profile (not currently available )

When UseAutoSelect is false, the user must select the bodies that the feature will affect.

When using cut or cavity features that result in multiple bodies, you cannot select to keep all of the resulting bodies or one or more selected bodies.