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Get DimXpert Chamfer Feature Example (VBA)

This example shows how to build and get attributes for the following DimXpert feature:

 

    *  Chamfer

'---------------------------------------------------------------------------

' Preconditions:

' 1. Open <SolidWorks_install_dir>\samples\tutorial\api\plate_tolstatus.sldprt.

' 2. Open the DimXpert toolbar from View > Toolbars

'    (select the first instance of Toolbars on the View menu).

' 3. Click the Auto Dimension Scheme icon in the DimXpert toolbar.

' 4. Ensure that the chamfer feature filter is selected.  

' 5. Click the green check mark to accept all settings.

' 6. Observe the following DimXpert features on the DimXpertManager tab

'    of the Management Panel:  Chamfer1.

' 7. Open an Immediate Window in the IDE.

' 8. Ensure that the latest SolidWorks DimXpert type library is loaded

'    in Tools > References.

' 9. Step through this macro (F8).

'

' Postconditions: Compare the output in the Immediate Window with

' the features displayed on the DimXpertManager tab of the Management Panel.

' NOTE: Because this part is used in a SolidWorks online tutorial,

' do not save any changes when you close it.

'---------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swModelDocExt As SldWorks.ModelDocExtension

Dim swSelMgr As SldWorks.SelectionMgr

Dim swConfig As SldWorks.Configuration

Dim swFeature As SldWorks.feature

Dim swAnn As SldWorks.feature

Dim swSchema As SldWorks.DimXpertManager

Dim swDXPart As DimXpertPart

Dim featureType As swDimXpertFeatureType_e

Dim chamferType As swDimXpertChamferType_e

Dim chamferAngleType As swDimXpertChamferAngleType_e

Dim features As Variant

Dim appliedFeatures As Variant

Dim appliedAnnotations As Variant

Dim appliedAnnotation As DimXpertAnnotation

Dim feature As DimXpertFeature

Dim appliedFeature As DimXpertFeature

Dim msgStr As String

Dim msgStr2 As String

Dim msgStr3 As String

Dim msgStr4 As String

Dim n As Long

Dim o As Long

Dim p As Long

Dim boolstatus As Boolean

Sub main()

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    

    Set swModelDocExt = swModel.Extension

    Set swSelMgr = swModel.SelectionManager

    

    ' Get the default DimXpert schema using IModelDocExtension.DimXpertManager()

    

    Set swSchema = swModelDocExt.DimXpertManager("Default", True)

    

    ' Get IDimXpertPart from the IDimXpertManager

    Set swDXPart = swSchema.DimXpertPart

    

    Dim featCount As Long

    featCount = swDXPart.GetFeatureCount

    msgStr = "Total of "

    msgStr2 = featCount

    msgStr = msgStr + msgStr2 + " features in " + (swSchema.SchemaName)

    Debug.Print ""

    Debug.Print msgStr

    

    ' Get IDimXpert features through IDimXpertPart

    

    features = swDXPart.GetFeatures

    

    msgStr = (swSchema.SchemaName) + " has the following features: "

    Debug.Print ""

    Debug.Print msgStr

    For n = 0 To UBound(features)

        Set feature = features(n)

        Debug.Print "  " + "Feature name: " + (feature.Name)

        

        featureType = feature.Type

        Call GetPatternType(featureType, msgStr2)

        

        msgStr = "     Feature type "

        msgStr3 = " is suppressed on the DimXpertManager tab? "

        msgStr4 = feature.IsSuppressed()

        Debug.Print msgStr + msgStr2 + msgStr3 + msgStr4

        

        msgStr = "     " + "Model feature: "

        Set swFeature = feature.GetModelFeature()

        If Not (swFeature Is Nothing) Then

            msgStr2 = swFeature.GetTypeName2()

            Debug.Print msgStr + msgStr2

        End If

        

        msgStr = "     " + "Number of SolidWorks face entities in this feature: "

        msgStr2 = feature.GetFaceCount

        Debug.Print msgStr + msgStr2

        

        msgStr = "     " + "Number of applied features: "

        msgStr2 = feature.GetAppliedFeatureCount()

        Debug.Print msgStr + msgStr2

        

        appliedFeatures = feature.GetAppliedFeatures()

        If Not (IsEmpty(appliedFeatures)) Then

            For o = 0 To UBound(appliedFeatures)

                Set appliedFeature = appliedFeatures(o)

                Debug.Print "        " + "Applied feature name: " + (appliedFeature.Name)

            Next

        End If

        

        msgStr = "     " + "Number of applied annotations: "

        msgStr2 = feature.GetAppliedAnnotationCount()

        Debug.Print msgStr + msgStr2

        

        appliedAnnotations = feature.GetAppliedAnnotations()

        If Not (IsEmpty(appliedAnnotations)) Then

            For p = 0 To UBound(appliedAnnotations)

                Set appliedAnnotation = appliedAnnotations(p)

                Debug.Print "        " + "Applied annotation name: " + (appliedAnnotation.Name)

            Next

        End If

        

        Debug.Print "     "

    Next

    

    ' If you know the name of a DimXpert feature, you can get it directly using IDimXpertPart.GetFeature("name"),

    ' which can return a general IDimXpertFeature or a more specific interface on the feature

    

    ' Get IDimXpertChamferFeature for the Chamfer1 feature

    

    Dim chamferFeature As IDimXpertChamferFeature

    Set chamferFeature = swDXPart.GetFeature("Chamfer1")

    msgStr = chamferFeature.Name + " is a DimXpert feature"

        Debug.Print ""

        Debug.Print msgStr

    Debug.Print ""

        

    ' Get the chamfer type

    chamferType = chamferFeature.chamferType

    msgStr = "     Chamfer type is "

    Call GetChamferType(chamferType, msgStr2)

    Debug.Print msgStr + msgStr2

     

    ' Get the chamfer angle

    Dim angle As Double

    angle = chamferFeature.angle

    msgStr = "     Chamfer angle is "

    msgStr2 = angle

    Debug.Print msgStr + msgStr2

    

    ' Get the angle type

    chamferAngleType = chamferFeature.angleType

    msgStr = "     Chamfer angle type is "

    Call GetChamferAngleType(chamferAngleType, msgStr2)

    Debug.Print msgStr + msgStr2

    

    'Get the chamfer distance properties

    Dim chamferDistance1 As Double

    Dim chamferDistance2 As Double

    chamferDistance1 = chamferFeature.Distance1

    msgStr = "     Chamfer distance 1 is "

    msgStr2 = chamferDistance1

    Debug.Print msgStr + msgStr2

    chamferDistance2 = chamferFeature.Distance2

    msgStr = "     Chamfer distance 2 is "

    msgStr2 = chamferDistance2

    Debug.Print msgStr + msgStr2

     

    

End Sub

Public Sub GetPatternType(ByRef featureType, ByRef msgStr2)

    If (featureType = swDimXpertFeature_Plane) Then

            msgStr2 = "Plane"

    ElseIf (featureType = swDimXpertFeature_Cylinder) Then

            msgStr2 = "Cylinder"

    ElseIf (featureType = swDimXpertFeature_Cone) Then

            msgStr2 = "Cone"

    ElseIf (featureType = swDimXpertFeature_Extrude) Then

            msgStr2 = "Extrude"

    ElseIf (featureType = swDimXpertFeature_Fillet) Then

            msgStr2 = "Fillet"

    ElseIf (featureType = swDimXpertFeature_Chamfer) Then

            msgStr2 = "Chamfer"

    ElseIf (featureType = swDimXpertFeature_CompoundHole) Then

            msgStr2 = "CompoundHole"

    ElseIf (featureType = swDimXpertFeature_CompoundWidth) Then

            msgStr2 = "CompoundWidth"

    ElseIf (featureType = swDimXpertFeature_CompoundNotch) Then

            msgStr2 = "CompoundNotch"

    ElseIf (featureType = swDimXpertFeature_CompoundClosedSlot3D) Then

            msgStr2 = "CompoundClosedSlot3D"

    ElseIf (featureType = swDimXpertFeature_IntersectPoint) Then

            msgStr2 = "IntersectPoint"

    ElseIf (featureType = swDimXpertFeature_IntersectLine) Then

            msgStr2 = "IntersectLine"

    ElseIf (featureType = swDimXpertFeature_IntersectCircle) Then

            msgStr2 = "IntersectCircle"

    ElseIf (featureType = swDimXpertFeature_IntersectPlane) Then

            msgStr2 = "IntersectPlane"

    ElseIf (featureType = swDimXpertFeature_Pattern) Then

            msgStr2 = "Pattern"

ElseIf (featureType = swDimXpertFeature_Sphere) Then

            msgStr2 = "Sphere"

ElseIf (featureType = swDimXpertFeature_BestfitPlane) Then

            msgStr2 = "Bestfit plane"

ElseIf (featureType = swDimXpertFeature_Surface) Then

            msgStr2 = "Surface"

    End If

    

End Sub

Public Sub GetChamferType(ByRef chamferType, ByRef msgStr2)

    If (chamferType = swDimXpertChamferType_DistanceAngle) Then

            msgStr2 = "Distance-Angle"

    ElseIf (chamferType = swDimXpertChamferType_DistanceDistance) Then

            msgStr2 = "Distance-Distance"

    ElseIf (chamferType = swDimXpertChamferType_Vertex) Then

            msgStr2 = "Vertex"

    End If

    

End Sub

Public Sub GetChamferAngleType(ByRef angleType, ByRef msgStr2)

    If (angleType = swDimXpertChamferAngleType_Concave) Then

            msgStr2 = "Concave"

    ElseIf (angleType = swDimXpertChamferAngleType_Convex) Then

            msgStr2 = "Convex"

    End If

    

End Sub



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