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Get DimXpert Compound Width and Best Fit Plane Features Example (VBA)

This example shows how to build a part and get attributes for the following DimXpert features:

 

    *  Compound width

    *  Best fit plane

'---------------------------------------------------------------------------

' Preconditions:

' 1. Open <SolidWorks_install_dir>\samples\tutorial\api\block.sldprt.

' 2. Open the DimXpert toolbar from View > Toolbars

'    (select the first instance of Toolbars on the View menu).

' 3. Create the best fit plane feature:

'    a. Click the Location Dimension icon on the DimXpert toolbar.

'    b. Select the left front face of the block.

'    c. Click the Compound Plane icon on the DimXpert pop up toolbar.

'    d. Select the right front face of the block.

'    e. Click the green check mark on the DimXpert pop up toolbar.

'    f. Select the back face of the block.

'    g. Click off the part to place the location dimension annotation.

' 4. Create the compound width feature:

'    a. Click the Size Dimension icon on the DimXpert toolbar.

'    b. Select a front face of the block.

'    c. Click the Width icon on the DimXpert pop up toolbar.

'    d. Select the back face of the block.

'    e. Click the green check mark on the DimXpert pop up toolbar.

'    f. Click off the part to place the size dimension annotation.

' 5. Observe the following DimXpert features on the DimXpertManager tab:  

'    Plane2, Plane3, Width1.

' 6. Open an Immediate window in the IDE.

' 7. Ensure that the latest SolidWorks DimXpert type library is loaded

'    in Tools > References.

'

' Postconditions: Compare the output in the Immediate Window

' with the features displayed on the DimXpertManager tab of the Management Panel.

' NOTE: Because this part is used in a SolidWorks online tutorial,

' do not save any changes when you close it.

'------------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks

Dim swModel As ModelDoc2

Dim swModelDocExt As ModelDocExtension

Dim swSelMgr As SelectionMgr

Dim swConfig As Configuration

Dim swFeature As feature

Dim swAnn As feature

Dim swSchema As DimXpertManager

Dim swDXPart As DimXpertPart

Dim featureType As swDimXpertFeatureType_e

Dim features As Variant

Dim appliedFeatures As Variant

Dim appliedAnnotations As Variant

Dim appliedAnnotation As DimXpertAnnotation

Dim feature As DimXpertFeature

Dim appliedFeature As DimXpertFeature

Dim msgStr As String

Dim msgStr2 As String

Dim msgStr3 As String

Dim msgStr4 As String

Dim n As Long

Dim o As Long

Dim p As Long

Dim boolstatus As Boolean

Sub main()

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    

    Set swModelDocExt = swModel.Extension

    Set swSelMgr = swModel.SelectionManager

    

    ' Get the default DimXpert schema using IModelDocExtension.DimXpertManager()

    

    Set swSchema = swModelDocExt.DimXpertManager("Default", True)

    

    ' Get IDimXpertPart from the IDimXpertManager

    Set swDXPart = swSchema.DimXpertPart

    

    Dim featCount As Long

    featCount = swDXPart.GetFeatureCount

    msgStr = "Total of "

    msgStr2 = featCount

    msgStr = msgStr + msgStr2 + " DimXpert features in " + (swSchema.SchemaName)

    Debug.Print ""

    Debug.Print msgStr

    

    ' Get IDimXpert features through IDimXpertPart

    

    features = swDXPart.GetFeatures

    

    msgStr = (swSchema.SchemaName) + " has the following features: "

    Debug.Print ""

    Debug.Print msgStr

    For n = 0 To UBound(features)

        Set feature = features(n)

        Debug.Print "  " + "Feature name: " + (feature.Name)

        

        featureType = feature.Type

        Call GetPatternType(featureType, msgStr2)

        

        msgStr = "     Feature type "

        msgStr3 = " is suppressed on the DimXpertManager tab? "

        msgStr4 = feature.IsSuppressed()

        Debug.Print msgStr + msgStr2 + msgStr3 + msgStr4

        

        msgStr = "     " + "Model feature: "

        Set swFeature = feature.GetModelFeature()

        If Not (swFeature Is Nothing) Then

            msgStr2 = swFeature.GetTypeName2()

            Debug.Print msgStr + msgStr2

        End If

        

        msgStr = "     " + "Number of SolidWorks face entities in this feature: "

        msgStr2 = feature.GetFaceCount

        Debug.Print msgStr + msgStr2

        

        msgStr = "     " + "Number of applied features: "

        msgStr2 = feature.GetAppliedFeatureCount()

        Debug.Print msgStr + msgStr2

        

        appliedFeatures = feature.GetAppliedFeatures()

        If Not (IsEmpty(appliedFeatures)) Then

            For o = 0 To UBound(appliedFeatures)

                Set appliedFeature = appliedFeatures(o)

                Debug.Print "        " + "Applied feature name: " + (appliedFeature.Name)

            Next

        End If

        

        msgStr = "     " + "Number of applied annotations: "

        msgStr2 = feature.GetAppliedAnnotationCount()

        Debug.Print msgStr + msgStr2

        

        appliedAnnotations = feature.GetAppliedAnnotations()

        If Not (IsEmpty(appliedAnnotations)) Then

            For p = 0 To UBound(appliedAnnotations)

                Set appliedAnnotation = appliedAnnotations(p)

                Debug.Print "        " + "Applied annotation name: " + (appliedAnnotation.Name)

            Next

        End If

        

        Debug.Print "     "

    Next

    

    ' If you know the name of a DimXpert feature, you can get it directly using IDimXpertPart.GetFeature("name"),

    ' which can return a general IDimXpertFeature or a more specific interface on the feature

    

    ' Get IDimXpertCompoundWidthFeature for the Width1 feature

    

    Dim widthFeature As IDimXpertCompoundWidthFeature

    Set widthFeature = swDXPart.GetFeature("Width1")

    msgStr = widthFeature.Name + " is a DimXpert Width feature"

    Debug.Print ""

    Debug.Print msgStr

    Debug.Print ""

        

    ' Get the nominal width coordinates

    

    Dim width As Double

    Dim x As Double

    Dim y As Double

    Dim z As Double

    Dim i As Double

    Dim j As Double

    Dim k As Double

   

    Debug.Print "Nominal width of Width1"

    Debug.Print ""

     boolstatus = widthFeature.GetNominalCompoundWidth(width, x, y, z, i, j, k)

    msgStr = "Width is "

    msgStr2 = width

    Debug.Print msgStr + msgStr2

    msgStr = "X-coordinate is "

    msgStr2 = x

    Debug.Print msgStr + msgStr2

    msgStr = "Y-coordinate is "

    msgStr2 = y

    Debug.Print msgStr + msgStr2

    msgStr = "Z-coordinate is "

    msgStr2 = z

    Debug.Print msgStr + msgStr2

    msgStr = "I-component of pierce vector is "

    msgStr2 = i

    Debug.Print msgStr + msgStr2

    msgStr = "J-component of pierce vector is "

    msgStr2 = j

    Debug.Print msgStr + msgStr2

    msgStr = "K-component of pierce vector is "

    msgStr2 = k

    Debug.Print msgStr + msgStr2

    Debug.Print ""

    

    ' Get whether the width is a hole or a pin

    

    boolstatus = widthFeature.Inner

    msgStr = "The width is for a hole and not a pin: "

    msgStr2 = boolstatus

    Debug.Print msgStr + msgStr2

    

    ' Get IDimXpertBestfitPlaneFeature for the Plane2 feature

    

    Dim bestfitPlaneFeature As IDimXpertBestfitPlaneFeature

    Set bestfitPlaneFeature = swDXPart.GetFeature("Plane2")

    msgStr = bestfitPlaneFeature.Name + " is a DimXpert Bestfit Plane feature"

    Debug.Print ""

    Debug.Print msgStr

    Debug.Print ""

    

    Dim featureCount As Integer

    featureCount = bestfitPlaneFeature.GetSubFeatureCount

    msgStr = "The number of sub-features of the bestfit plane is "

    msgStr2 = featureCount

    Debug.Print msgStr + msgStr2

    

    features = bestfitPlaneFeature.GetSubFeatures

    For n = 0 To UBound(features)

        Set feature = features(n)

        Debug.Print "  " + "Feature name: " + (feature.Name)

        

        featureType = feature.Type

        Call GetPatternType(featureType, msgStr2)

        

        msgStr = "     Feature type is "

        

        Debug.Print msgStr + msgStr2

    Next

    

End Sub

Public Sub GetPatternType(ByRef featureType, ByRef msgStr2)

    If (featureType = swDimXpertFeature_Plane) Then

            msgStr2 = "Plane"

    ElseIf (featureType = swDimXpertFeature_Cylinder) Then

            msgStr2 = "Cylinder"

    ElseIf (featureType = swDimXpertFeature_Cone) Then

            msgStr2 = "Cone"

    ElseIf (featureType = swDimXpertFeature_Extrude) Then

            msgStr2 = "Extrude"

    ElseIf (featureType = swDimXpertFeature_Fillet) Then

            msgStr2 = "Fillet"

    ElseIf (featureType = swDimXpertFeature_Chamfer) Then

            msgStr2 = "Chamfer"

    ElseIf (featureType = swDimXpertFeature_CompoundHole) Then

            msgStr2 = "CompoundHole"

    ElseIf (featureType = swDimXpertFeature_CompoundWidth) Then

            msgStr2 = "CompoundWidth"

    ElseIf (featureType = swDimXpertFeature_CompoundNotch) Then

            msgStr2 = "CompoundNotch"

    ElseIf (featureType = swDimXpertFeature_CompoundClosedSlot3D) Then

            msgStr2 = "CompoundClosedSlot3D"

    ElseIf (featureType = swDimXpertFeature_IntersectPoint) Then

            msgStr2 = "IntersectPoint"

    ElseIf (featureType = swDimXpertFeature_IntersectLine) Then

            msgStr2 = "IntersectLine"

    ElseIf (featureType = swDimXpertFeature_IntersectCircle) Then

            msgStr2 = "IntersectCircle"

    ElseIf (featureType = swDimXpertFeature_IntersectPlane) Then

            msgStr2 = "IntersectPlane"

    ElseIf (featureType = swDimXpertFeature_Pattern) Then

            msgStr2 = "Pattern"

    ElseIf (featureType = swDimXpertFeature_Sphere) Then

            msgStr2 = "Sphere"

    ElseIf (featureType = swDimXpertFeature_BestfitPlane) Then

            msgStr2 = "Bestfit Plane"

    ElseIf (featureType = swDimXpertFeature_Surface) Then

            msgStr2 = "Surface"

    End If

    

End Sub



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