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Get DimXpert Compound Width and Best Fit Plane Features Example (VB.NET)

This example shows how to build a part and get attributes for the following DimXpert features:

 

    *  Compound width

    *  Best fit plane

'---------------------------------------------------------------------------

' Preconditions:

' 1. Open <SolidWorks_install_dir>\samples\tutorial\api\block.sldprt.

' 2. Open the DimXpert toolbar from View > Toolbars

'    (select the first instance of Toolbars on the View menu).

' 3. Create the best fit plane feature:

'    a. Click the Location Dimension icon on the DimXpert toolbar.

'    b. Select the left front face of the block.

'    c. Click the Compound Plane icon on the DimXpert pop up toolbar.

'    d. Select the right front face of the block.

'    e. Click the green check mark on the DimXpert pop up toolbar.

'    f. Select the back face of the block.

'    g. Click off the part to place the location dimension annotation.

' 4. Create the compound width Feature:

'    a. Click the Size Dimension icon on the DimXpert toolbar.

'    b. Select a front face of the block.

'    c. Click the Width icon on the DimXpert pop up toolbar.

'    d. Select the back face of the block.

'    e. Click the green check mark on the DimXpert pop up toolbar.

'    f. Click off the part to place the size dimension annotation.

' 5. Observe the following DimXpert features on the DimXpertManager tab:  

'    Plane2, Plane3, Width1.

' 6. Open an Immediate Window in the IDE.

' 7. Ensure that the SolidWorks.Interop.swdimxpert.dll interop assembly

'    is loaded (right-click on the project in the Project Explorer window,

'    click Add Reference, click the .NET tab).

'

' Postconditions: Compare the output in the Immediate Window

' with the features displayed on the DimXpertManager tab of the Management Panel.

' NOTE: Because this part is used in a SolidWorks online tutorial,

' do not save any changes when you close it.

'--------------------------------------------------

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swdimxpert

Imports SolidWorks.Interop.swconst

Imports System

Imports System.Diagnostics

Partial Class SolidWorksMacro

    

    Dim swModel As IModelDoc2

    Dim swModelDocExt As IModelDocExtension

    Dim swSelMgr As ISelectionMgr

    Dim swConfig As IConfiguration

    Dim swFeature As IFeature

    Dim swAnn As IFeature

    Dim swSchema As IDimXpertManager

    Dim swDXPart As IDimXpertPart

    Dim featureType As swDimXpertFeatureType_e

    Dim features As Object

    Dim appliedFeatures As Object

    Dim appliedAnnotations As Object

    Dim appliedAnnotation As IDimXpertAnnotation

    Dim feature As IDimXpertFeature

    Dim appliedFeature As IDimXpertFeature

    Dim msgStr As String

    Dim msgStr2 As String

    Dim msgStr3 As String

    Dim msgStr4 As String

    Dim n As Long

    Dim o As Long

    Dim p As Long

    Dim boolstatus As Boolean

    Sub main()

        swModel = swApp.ActiveDoc

        swModelDocExt = swModel.Extension

        swSelMgr = swModel.SelectionManager

        ' Get the default DimXpert schema using IModelDocExtension.DimXpertManager()

        swSchema = swModelDocExt.DimXpertManager("Default", True)

        ' Get IDimXpertPart from the IDimXpertManager

        swDXPart = swSchema.DimXpertPart

        Dim featCount As Long

        featCount = swDXPart.GetFeatureCount

        msgStr = "Total of "

        msgStr2 = featCount

        msgStr = msgStr + msgStr2 + " DimXpert features in " + (swSchema.SchemaName)

        Debug.Print("")

        Debug.Print(msgStr)

        ' Get IDimXpert features through IDimXpertPart

        features = swDXPart.GetFeatures

        msgStr = (swSchema.SchemaName) + " has the following features: "

        Debug.Print("")

        Debug.Print(msgStr)

        For n = 0 To UBound(features)

            feature = features(n)

            Debug.Print("  " + "Feature name: " + (feature.Name))

            featureType = feature.Type

            Call GetPatternType(featureType, msgStr2)

            msgStr = "     Feature type "

            msgStr3 = " is suppressed on the DimXpertManager tab? "

            msgStr4 = feature.IsSuppressed()

            Debug.Print(msgStr + msgStr2 + msgStr3 + msgStr4)

            msgStr = "     " + "Model feature: "

            swFeature = feature.GetModelFeature()

            If Not (swFeature Is Nothing) Then

                msgStr2 = swFeature.GetTypeName2()

                Debug.Print(msgStr + msgStr2)

            End If

            msgStr = "     " + "Number of SolidWorks face entities in this feature: "

            msgStr2 = feature.GetFaceCount

            Debug.Print(msgStr + msgStr2)

            msgStr = "     " + "Number of applied features: "

            msgStr2 = feature.GetAppliedFeatureCount()

            Debug.Print(msgStr + msgStr2)

            appliedFeatures = feature.GetAppliedFeatures()

            If Not (IsNothing(appliedFeatures)) Then

                For o = 0 To UBound(appliedFeatures)

                    appliedFeature = appliedFeatures(o)

                    Debug.Print("        " + "Applied feature name: " + (appliedFeature.Name))

                Next

            End If

            msgStr = "     " + "Number of applied annotations: "

            msgStr2 = feature.GetAppliedAnnotationCount()

            Debug.Print(msgStr + msgStr2)

            appliedAnnotations = feature.GetAppliedAnnotations()

            If Not (IsNothing(appliedAnnotations)) Then

                For p = 0 To UBound(appliedAnnotations)

                    appliedAnnotation = appliedAnnotations(p)

                    Debug.Print("        " + "Applied annotation name: " + (appliedAnnotation.Name))

                Next

            End If

            Debug.Print("     ")

        Next

        ' If you know the name of a DimXpert feature, you can get it directly using IDimXpertPart.GetFeature("name"),

        ' which can return a general IDimXpertFeature or a more specific interface on the feature

        ' Get IDimXpertCompoundWidthFeature for the Width1 feature

        Dim widthFeature As IDimXpertCompoundWidthFeature

        widthFeature = swDXPart.GetFeature("Width1")

        msgStr = widthFeature.Name + " is a DimXpert Width feature"

        Debug.Print("")

        Debug.Print(msgStr)

        Debug.Print("")

        ' Get the nominal width coordinates

        Dim width As Double

        Dim x As Double

        Dim y As Double

        Dim z As Double

        Dim i As Double

        Dim j As Double

        Dim k As Double

        Debug.Print("Nominal width of Width1")

        Debug.Print("")

        boolstatus = widthFeature.GetNominalCompoundWidth(width, x, y, z, i, j, k)

        msgStr = "Width is "

        msgStr2 = width

        Debug.Print(msgStr + msgStr2)

        msgStr = "X-coordinate is "

        msgStr2 = x

        Debug.Print(msgStr + msgStr2)

        msgStr = "Y-coordinate is "

        msgStr2 = y

        Debug.Print(msgStr + msgStr2)

        msgStr = "Z-coordinate is "

        msgStr2 = z

        Debug.Print(msgStr + msgStr2)

        msgStr = "I-component of pierce vector is "

        msgStr2 = i

        Debug.Print(msgStr + msgStr2)

        msgStr = "J-component of pierce vector is "

        msgStr2 = j

        Debug.Print(msgStr + msgStr2)

        msgStr = "K-component of pierce vector is "

        msgStr2 = k

        Debug.Print(msgStr + msgStr2)

        Debug.Print("")

        ' Get whether the width is a hole or a pin

        boolstatus = widthFeature.Inner

        msgStr = "The width is for a hole and not a pin: "

        msgStr2 = boolstatus

        Debug.Print(msgStr + msgStr2)

        ' Get IDimXpertBestfitPlaneFeature for the Plane2 feature

        Dim bestfitPlaneFeature As IDimXpertBestfitPlaneFeature

        bestfitPlaneFeature = swDXPart.GetFeature("Plane2")

        msgStr = bestfitPlaneFeature.Name + " is a DimXpert Bestfit Plane feature"

        Debug.Print("")

        Debug.Print(msgStr)

        Debug.Print("")

        Dim featureCount As Integer

        featureCount = bestfitPlaneFeature.GetSubFeatureCount

        msgStr = "The number of sub-features of the bestfit plane is "

        msgStr2 = featureCount

        Debug.Print(msgStr + msgStr2)

        features = bestfitPlaneFeature.GetSubFeatures

        For n = 0 To UBound(features)

            feature = features(n)

            Debug.Print("  " + "Feature name: " + (feature.Name))

            featureType = feature.Type

            Call GetPatternType(featureType, msgStr2)

            msgStr = "     Feature type is "

            Debug.Print(msgStr + msgStr2)

        Next

    End Sub

    Public Sub GetPatternType(ByRef featureType As swDimXpertFeatureType_e, ByRef msgStr2 As String)

        If (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Plane) Then

            msgStr2 = "Plane"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Cylinder) Then

            msgStr2 = "Cylinder"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Cone) Then

            msgStr2 = "Cone"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Extrude) Then

            msgStr2 = "Extrude"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Fillet) Then

            msgStr2 = "Fillet"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Chamfer) Then

            msgStr2 = "Chamfer"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_CompoundHole) Then

            msgStr2 = "CompoundHole"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_CompoundWidth) Then

            msgStr2 = "CompoundWidth"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_CompoundNotch) Then

            msgStr2 = "CompoundNotch"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_CompoundClosedSlot3D) Then

            msgStr2 = "CompoundClosedSlot3D"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_IntersectPoint) Then

            msgStr2 = "IntersectPoint"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_IntersectLine) Then

            msgStr2 = "IntersectLine"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_IntersectCircle) Then

            msgStr2 = "IntersectCircle"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_IntersectPlane) Then

            msgStr2 = "IntersectPlane"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Pattern) Then

            msgStr2 = "Pattern"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Sphere) Then

            msgStr2 = "Sphere"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_BestfitPlane) Then

            msgStr2 = "Bestfit Plane"

        ElseIf (featureType = swDimXpertFeatureType_e.swDimXpertFeature_Surface) Then

            msgStr2 = "Surface"

        End If

    End Sub

   

    Public swApp As SldWorks

End Class



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