Hide Table of Contents

Weld Bead PropertyManager

The Weld Bead PropertyManager lets you insert and define weld beads.

To display this PropertyManager, in a part, click Weld Bead (Weldments toolbar) or Insert > Weldments > Weld Bead . In an assembly, click Insert > Assembly Feature > Weld Bead .

Weld Path

Smart Weld Selection Tool Lets you drag the pointer over the faces where you want to apply a weld bead.
  Select Faces Lists each unique weld path. The weld path is the course that the weld bead follows around the model.

When you select a weld path in this box, the weld path preview in the graphics area changes colors. A pink preview indicates that the weld path is active. A yellow preview indicates that the weld path is inactive. Any changes you make in the PropertyManager apply to the active weld path.

  New Weld Path Lets you define a new weld path. Click New Weld Path to create a new path that is disjointed from the previously created weld path. You do not need to use New Weld Path if you use the Smart Weld Selection Tool.
Weld paths are supported between two bodies. You cannot define a weld path among three or more bodies or between the faces of one body.

Settings

The options in Settings apply per weld path. When you select an item under Weld Path, you can change the following options for the selected weld path.

  Weld selection Lists the faces or edges where the weld bead is applied.
Bead size Sets the bead thickness.
  Tangent propagation Applies the weld bead to all edges that are tangent to the selected face or edge.

When cleared, you can select:

Selection

Applies the weld bead to the selected face or edge.

Both sides

Applies the weld bead to the selected face or edge and to the opposite face or edge.

All around

Applies the weld bead to the selected face or edge and to all adjacent faces and edges.

  Define Weld Symbol Opens the Weld Symbol dialog box so you can define the weld symbol settings. The weld symbol is attached to the active weld bead.

From/To Length

You can use the settings below or use the handles in the graphics area to manipulate the weld bead.
  Start point Lets you define where to start the weld bead from the first end.
Reverse Direction Starts the weld bead in from the opposite end.
  Weld length Sets the length of the weld bead.
Weld bead defined with a Start point and Weld length

Intermittent Weld

  Gap and weld length Sets the Weld length and Gap for intermittent weld beads.
  Pitch and weld length Sets the Weld length and Pitch for intermittent weld beads. Pitch is defined as the weld length plus the gap. It is calculated from the center of one weld bead to the center of the next weld bead.
  Staggered Available for weld beads set to Both sides. The weld beads alternate positioning on either side of the bodies to weld.



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Weld Bead PropertyManager
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: SOLIDWORKS 2013 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.