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Dimension Value PropertyManager

In the Dimension Value PropertyManager, you can specify the display of dimensions. If you select multiple dimensions, only the properties that apply to all the selected dimensions are available.

Dimension Assist Tools

Allows you to dimension a drawing with smart or DimXpert (for drawings) dimensioning. Click DimXpert PM_dimXpert.gif to access the DimXpert (for drawings) and Autodimension tabs.

PM_smart_dimensioning.gif Smart dimensioning Lets you create dimensions with the Smart Dimension Tool_Smart_Dimensions_Relations.gif tool.
PM_dimxpert_rapid_dim_manip.gif Rapid dimensioning Lets you enable or disable the rapid dimension manipulator. Select to enable; clear to disable. This setting persists across sessions.
PM_dimXpert.gif DimXpert Lets you apply dimensions to fully define manufacturing features (patterns, slots, pockets, fillets, etc.) and locating dimensions, using DimXpert for drawings.

Style

Style

Tolerance/Precision

  Callout value Choose a value in the currently selected dimension. This is available for dimensions with multiple values in the callout.
PM_tolerance_type_dim.gif Tolerance Type Select from the list. Selections available depend on the type of dimension. Examples of Dimension Tolerance and Precision
PM_max_variation_dim.gif Maximum Variation  
PM_min_variation_dim.gif Minimum Variation  
PM_precision_dim.gif Unit Precision Select the number of digits after the decimal point from the list for the dimension value.
PM_dim_precision_tol.gif Tolerance Precision Select the number of digits after the decimal point for tolerance values.
  Link precisions with model For imported dimensions, sets changes in unit or tolerance precision to be parametric with the model.
  Configurations (Parts and assemblies only.) Applies the dimension tolerance to specific configurations for driven dimensions only.
PM_dim_tol_fit_class.gif Classification (Fit, Fit with tolerance, or Fit (tolerance only).) When you select either Hole Fit or Shaft Fit (below), the list for the other category (Hole Fit or Shaft Fit) is filtered based on the classification.
PM_dim_tol_hole.gif PM_dim_tol_shaft.gif Hole Fit and Shaft Fit (Fit, Fit with tolerance, or Fit (tolerance only).) Select from the lists, or type any text.
Bilateral tolerances (Maximum Variation and Minimum Variation) are available in the Fit with tolerance or Fit (tolerance only) type if you specify Hole Fit or Shaft Fit, but not both.
  Fit tolerance display (Fit, Fit with tolerance, or Fit (tolerance only).)

Stacked with line display PM_dim_tol_fit_withline.gif

Stacked without line display PM_dim_tol_fit_stacked.gif

Linear display PM_dim_tol_fit_linear.gif

  Show parentheses Parentheses are available for Bilateral, Symmetric, and Fit with tolerance tolerance types. Parentheses are available for Fit with tolerance if you specify Hole Fit or Shaft Fit, but not both.

2nd Tolerance/Precision

Available for chamfer dimensions.

Primary Value

Primary Value is displayed for driving dimensions and can be changed to alter the model. You can override the dimension value. For dimensions that are not referenced, you can change the dimension name. Driven (reference) dimensions list a value and name, but you cannot change them.

  Name The name of the selected dimension.
  Dimension value The value of the selected dimension.
  Override value Select to override the primary value, and type a new value. If you clear Override value, the dimension returns to its original value but retains the tolerance. Override values do not automatically update when geometry changes.
dim_no_override.gif
Original value
dim_override.gif
Overridden value
PM_reverse_direction.gif Reverse Direction Change the dimension direction between positive and negative sense.

Dimension Text

PM_AddParenthesis.gif Add Parentheses You can display driven (reference) dimensions with or without parentheses. They are displayed with parentheses by default.
dimension_symm_parentheses.gif
PM_CenterDim.gif Center Dimension When you drag dimension text between the extension lines, the dimension text snaps to the center of the extension lines.
dimension_center.gif
PM_InspectionDim.gif Inspection Dimension Dimension_Inspection.gif
PM_OffsetText.gif Offset Text Offsets dimension text from the dimension line using a leader.
dimension_offset_text.gif
  Text The dimension appears automatically in the center text box, represented by <DIM>. Place the pointer anywhere in the text box to insert text. If you delete <DIM>, you can reinsert the value by clicking Add Value PM_add_value.gif.
dim_text.gif
dim_ref.gif
dim_text2.gif
For some types of dimensions, additional text appears automatically. For example, a Hole Callout for a counterbore hole displays the diameter and depth of the hole (<MOD-DIAM><DIM><HOLE-DEPTH>xx). Hole Callouts for holes created in the Hole Wizard display information from the Hole Wizard. You can edit the text and insert variables from the Callout Variables dialog box.
  Justify You can justify text horizontally and, for some standards, you can justify the leader vertically.
  • Left Justify PM_Text_Justify_Left.gif, Center Justify PM_Text_Justify_Center.gif, Right Justify PM_Text_Justify_Right.gif
dim_left_justify.gif
Left Justify
dim_center_justify.gif
Center Justify
dim_right_justify.gif
Right Justify
  • Top Justify PM_dim_Justify_Top.gif, Middle Justify PM_dim_Justify_Middle.gif, Bottom Justify PM_dim_Justify_Bottom.gif
dim_top_justify.gif
Top Justify
dim_middle_justify.gif
Middle Justify
dim_bottom_justify.gif
Bottom Justify
  Symbols Click to place the pointer where you want a standard symbol. Click a symbol icon or click More to access the Symbol Library.
dim_w_symbol.gif
  Chamfer Dimension Display

Distance X Distance PM_dim_chamfer_DXD.gif

Distance X Angle PM_dim_chamfer_DXA.gif

Angle X Distance PM_dim_chamfer_AXD.gif

C Distance PM_dim_chamfer_C.gif

Available only for chamfers with 45° angles.

Dual Dimension

Specifies that the dimension is displayed in both the document's unit system and the dual dimension units. Both units are specified in Document Properties - Units . You set where the alternate units are displayed in Document Properties - Dimensions . Dual dimensions are displayed in brackets.

PM_precision_dim.gif Unit Precision Select the number of digits after the decimal point from the list for the dimension value.
PM_Tol_Precision_DualDim.gif Tolerance Precision Select the number of digits after the decimal point for tolerance values.
  Link precisions with model For imported dimensions, sets changes in unit or tolerance precision for the secondary units to be parametric with the model.


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