Create Hole Wizard Hole Example (C#)

This example shows how to create a hole wizard hole.

//---------------------------------

// Preconditions: SolidWorks is running.

//

// Postconditions: A model is created and a hole wizard

// hole is created in that model.

//-----------------------------------

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System;

namespace HoleWizard4FeatureManager_CSharp.csproj

{

    partial class SolidWorksMacro

    {

        public void Main()

        {

            ModelDoc2 swModel = default(ModelDoc2);

            ModelDocExtension swModelDocExt = default(ModelDocExtension);

            FeatureManager swFeatMgr = default(FeatureManager);

            Feature swFeat = default(Feature);

            SketchManager swSketchMgr = default(SketchManager);

            object sketchLines = null;

            int longstatus = 0;

            bool boolstatus = false;

            double[] P1 = new double[3];

            double[] P2 = new double[3];

            double[] P3 = new double[3];

            // Create the model for the wizard hole

            swApp.ResetUntitledCount(0, 0, 0);

            swModel = (ModelDoc2)swApp.NewDocument("C:\\Documents and Settings\\All Users\\Application Data\\SolidWorks\\SolidWorks 2010\\templates\\Part.prtdot", 0, 0, 0);

            swApp.ActivateDoc2("Part1", false, ref longstatus);

            swModel = (ModelDoc2)swApp.ActiveDoc;

            swSketchMgr = swModel.SketchManager;

            swModelDocExt = swModel.Extension;

            swFeatMgr = swModel.FeatureManager;

            sketchLines = swSketchMgr.CreateCornerRectangle(-0.05096498314664, 0.05060941349678, 0, 0.1021670127265, -0.05037236706354, 0);

            boolstatus = swModelDocExt.SelectByID2("Line2", "SKETCHSEGMENT", 0, 0, 0, false, 0, null, 0);

            boolstatus = swModelDocExt.SelectByID2("Line2", "SKETCHSEGMENT", 0, 0, 0, true, 0, null, 0);

            boolstatus = swModelDocExt.SelectByID2("Line2", "SKETCHSEGMENT", 0, 0, 0, true, 0, null, 0);

            boolstatus = swModelDocExt.SelectByID2("Line2", "SKETCHSEGMENT", 0, 0, 0, true, 0, null, 0);

            swFeat = swFeatMgr.FeatureExtrusion2(true, false, false, 0, 0, 0.381, 0.381, false, false, false,

            false, 0.01745329251994, 0.01745329251994, false, false, false, false, true, true, true,

            0, 0, false);

            //Create three points for the reference plane

            P1[0] = -0.0141556764402858;

            P1[1] = 0.00194061273859598;

            P1[2] = 0;

            P2[0] = -0.0141556764402858;

            P2[1] = 0.00194061273859598;

            P2[2] = 1;

            P3[0] = -0.149976101832345;

            P3[1] = -0.988792859011662;

            P3[2] = 0;

            //Create the reference plane

            swModel.CreatePlaneFixed2(P1, P2, P3, false);

            //Select reference plane

            boolstatus = swModelDocExt.SelectByID2("Plane1", "PLANE", -0.0156784487003801, -0.00916715285390111, 0.0558270998665543, false, 0, null, 0);

            // Create the hole wizard hole

            swFeat = swFeatMgr.HoleWizard4((int)swWzdGeneralHoleTypes_e.swWzdCounterSink, (int)swWzdHoleStandards_e.swStandardAnsiMetric, (int)swWzdHoleStandardFastenerTypes_e.swStandardAnsiMetricFlatHead82, "M2", (int)swEndConditions_e.swEndCondThroughAll, 0.0102, 0.010312189893273, 0.0044, 1.57079632679489, 0.000152189893272978,

            0, 2.05948851735331, 0, 0, 0, 1, 0, 0, 0, "",

            false, true, true, true, true, false);

        }

        public SldWorks swApp;

    }

}