Create a Structural-Member Group Example (C#)
This example shows how to create structural-member groups for weldment features.
//
--------------------------------------------------------------------------
// Preconditions:
// 1. Ensure
that the specified weldment profile and path exist.
// 2. If
necessary, modify the path in both InsertStructuralWeldment3 methods.
//
// Postconditions:
// 1. Two
structural-member features are created.
// 2. Each
feature consists of one structural-member group of two
// sketch segments.
// 3. Inspect
the Immediate Window for information.
//---------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
using System.Diagnostics;
namespace CreateStructureMemberGroup_CSharp.csproj
{
partial
class SolidWorksMacro
{
ModelDoc2
Part;
bool
boolstatus;
FeatureManager
FeatMgr;
SelectionMgr
SelMgr;
Feature
swWeldFeat;
StructuralMemberFeatureData
swWeldFeatData;
public
void Main()
{
string
MacroFolder = null;
MacroFolder
= swApp.GetCurrentMacroPathFolder();
swApp.SetCurrentWorkingDirectory(MacroFolder);
string
Template = null;
Template
= swApp.GetUserPreferenceStringValue((int)swUserPreferenceStringValue_e.swDefaultTemplatePart);
Part
= (ModelDoc2)swApp.NewDocument(Template, 0, 0, 0);
FeatMgr
= Part.FeatureManager;
SelMgr
= (SelectionMgr)Part.SelectionManager;
Part.ClearSelection2(true);
object
vSkLines = null;
vSkLines
= Part.SketchManager.CreateCornerRectangle(-0.1872393706766, 0.1133237194389,
0, -0.07003610048208, 0.009188409684237, 0);
Part.ClearSelection2(true);
vSkLines
= Part.SketchManager.CreateCornerRectangle(0.06513561531715, 0.03369083550887,
0, 0.1807053904567, -0.08106219210316, 0);
Part.ClearSelection2(true);
Part.SketchManager.InsertSketch(true);
Part.ViewZoomtofit2();
Feature
myFeature = default(Feature);
myFeature
= Part.FeatureManager.InsertWeldmentFeature();
StructuralMemberGroup
Group1 = default(StructuralMemberGroup);
Group1
= FeatMgr.CreateStructuralMemberGroup();
SketchSegment[]
segments1 = new SketchSegment[2];
StructuralMemberGroup[]
GroupArray1 = new StructuralMemberGroup[1];
boolstatus
= Part.Extension.SelectByID2("Line1@Sketch1", "EXTSKETCHSEGMENT",
-0.1495427140733, 0.1133237194389, 0, false, 0, null, 0);
boolstatus
= Part.Extension.SelectByID2("Line2@Sketch1", "EXTSKETCHSEGMENT",
-0.1872393706766, 0.08238014634844, 0, true, 0, null, 0);
segments1[0]
= (SketchSegment)SelMgr.GetSelectedObject6(1, 0);
segments1[1]
= (SketchSegment)SelMgr.GetSelectedObject6(2, 0);
Group1.Segments = segments1;
GroupArray1[0]
= Group1;
myFeature
= Part.FeatureManager.InsertStructuralWeldment3("C:\\Program
Files\\SolidWorks Corp\\SolidWorks\\data\\weldment profiles\\ansi inch\\c
channel\\3 x 5.sldlfp", 1, 0, false, GroupArray1);
Part.ClearSelection2(true);
StructuralMemberGroup
Group2 = default(StructuralMemberGroup);
Group2
= FeatMgr.CreateStructuralMemberGroup();
SketchSegment[]
segments2 = new SketchSegment[2];
StructuralMemberGroup[]
GroupArray2 = new StructuralMemberGroup[1];
boolstatus
= Part.Extension.SelectByID2("Line5@Sketch1", "EXTSKETCHSEGMENT",
0.1185825251083, 0.03369083550887, 0, false, 0, null, 0);
boolstatus
= Part.Extension.SelectByID2("Line6@Sketch1", "EXTSKETCHSEGMENT",
0.06513561531715, -0.02774616865332, 0, true, 0, null, 0);
segments2[0]
= (SketchSegment)SelMgr.GetSelectedObject6(1, 0);
segments2[1]
= (SketchSegment)SelMgr.GetSelectedObject6(2, 0);
Group2.Segments = segments2;
GroupArray2[0]
= Group2;
myFeature
= Part.FeatureManager.InsertStructuralWeldment3("C:\\Program
Files\\SolidWorks Corp\\SolidWorks\\data\\weldment profiles\\ansi inch\\c
channel\\3 x 5.sldlfp", 1, 0, false, GroupArray2);
Part.ClearSelection2(true);
//
Get Group Information
StructuralMemberGroup
Group = default(StructuralMemberGroup);
Object[]
vGroups = null;
Object[]
vSegments = null;
SketchSegment
skSegment = default(SketchSegment);
boolstatus
= Part.Extension.SelectByID2("Structural Member1", "BODYFEATURE",
0, 0, 0, false, 0, null, 0);
swWeldFeat
= (Feature)SelMgr.GetSelectedObject6(1, 0);
swWeldFeatData
= (StructuralMemberFeatureData)swWeldFeat.GetDefinition();
swWeldFeatData.AccessSelections(Part,
null);
Debug.Print("");
Debug.Print("Groups
Count : " + swWeldFeatData.GetGroupsCount());
Debug.Print("
Feature Name : " + swWeldFeat.Name);
vGroups
= (Object[])swWeldFeatData.Groups;
long
i = 0;
long
j = 0;
for
(i = vGroups.GetLowerBound(0); i <= vGroups.GetUpperBound(0); i++)
{
Group
= (StructuralMemberGroup)vGroups[i];
Debug.Print("
Segment Count in Group " + i + 1 + " : " + Group.GetSegmentsCount());
Debug.Print("
Rotational angle of group: " + Group.Angle.ToString());
vSegments
= (Object[])Group.Segments;
for
(j = vSegments.GetLowerBound(0); j <= vSegments.GetUpperBound(0); j++)
{
skSegment
= (SketchSegment)vSegments[j];
skSegment.Select(false);
}
}
swWeldFeatData.ReleaseSelectionAccess();
boolstatus
= Part.Extension.SelectByID2("Structural Member2", "BODYFEATURE",
0, 0, 0, false, 0, null, 0);
swWeldFeat
= (Feature)SelMgr.GetSelectedObject6(1, 0);
swWeldFeatData
= (StructuralMemberFeatureData)swWeldFeat.GetDefinition();
swWeldFeatData.AccessSelections(Part,
null);
Debug.Print("");
Debug.Print("Groups
Count : " + swWeldFeatData.GetGroupsCount());
Debug.Print("
Feature Name : " + swWeldFeat.Name);
vGroups
= (Object[])swWeldFeatData.Groups;
for
(i = vGroups.GetLowerBound(0); i <= vGroups.GetUpperBound(0); i++)
{
Group
= (StructuralMemberGroup)vGroups[i];
Debug.Print("
Segment Count in Group " + i + 1 + " : " + Group.GetSegmentsCount());
Debug.Print("
Rotational angle of group: " + Group.Angle.ToString());
vSegments
= (Object[])Group.Segments;
for
(j = vSegments.GetLowerBound(0); j <= vSegments.GetUpperBound(0); j++)
{
skSegment
= (SketchSegment)vSegments[j];
skSegment.Select(false);
}
}
swWeldFeatData.ReleaseSelectionAccess();
}
public
SldWorks swApp;
}
}