Insert Sheet Metal Hem Example (C#)

//----------------------------------------------------------------------------
// Preconditions:
// 1. Open a sheet metal part.
// 2. Select the edge to which to add a hem.
//
// Postconditions:
// 1. Hem1, an open hem with a custom relief of type Obround and
//    a relief ratio of 1.0, is added to the FeatureManager design tree.
// 2. The hem type as defined in swHemTypes_e is printed to the Immediate window.
// ---------------------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace SheetMetalHem_CSharp.csproj
{
    partial class SolidWorksMacro
    {

        ModelDoc2 Part;
        CustomBendAllowance CBAObject;
        Feature myFeature;
        HemFeatureData myHem;

        public void Main()
        {
            Part = (ModelDoc2)swApp.ActiveDoc;

            CBAObject = Part.FeatureManager.CreateCustomBendAllowance();
            CBAObject.Type = 2;
            CBAObject.KFactor = 0.5;

            // Insert an open hem of custom relief type Obround and relief ratio 1.0
            myFeature = Part.FeatureManager.InsertSheetMetalHem2((int)swHemTypes_e.swHemTypeOpen, (int)swHemPositionTypes_e.swHemPositionTypeOutside, false, 0.01, 0.01, 0, 0.005, 0.0011, CBAObject, false,
            (int)swSheetMetalReliefTypes_e.swSheetMetalReliefObround, 0, true, 1.0, 0, 0);
            Part.ClearSelection2(true);

            myHem = (HemFeatureData)myFeature.GetDefinition();
            Debug.Print("Hem type as defined in swHemTypes_e: " + myHem.Type);
        }



        public SldWorks swApp;

    }

}