Insert Weldment Features Example (C#)
This example shows how to insert the following weldment
features into the FeatureManager design tree:
*
End cap
feature
*
Fillet
bead feature
*
Gusset
feature
*
Structural
weldment
*
Sub weld
folder
*
Weldment
trim feature
//---------------------------------------------------------------------------
// Preconditions:
// 1.
Open:
// <SolidWorks_install_dir>\samples\tutorial\weldments\weldment_box2.sldprt
// 2.
Expand the Cut list folder in the FeatureManager design tree and observe
its contents.
// 3.
Delete End cap1 from the FeatureManager design tree.
//
// Postconditions:
// Observe
the following in the FeatureManager design tree:
// *
Gusset1 moves to the sub weld folder, Sub Folder1, in the Cut list folder
// *
Trim/Extend8 feature appears at the bottom of the design tree and at the
end of the Cut list folder
// *
Structural Member6 feature appears at the bottom of the design tree and
at the end of the Cut list folder
// *
End cap5 feature appears at the bottom of the design tree and in the Cut
list folder
// *
Gusset5 feature appears at the bottom of the design tree and in the Cut
list folder
// *
Fillet Bead5 feature appears at the bottom of the design tree and in the
Cut list folder
// NOTE:
Because this part is used in a SolidWorks online tutorial,
// do not save
any changes when you close it.
//---------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
namespace InsertWeldmentFeatures_CSharp.csproj
{
partial
class SolidWorksMacro
{
FeatureManager
fm;
SelectionMgr
selMgr;
ModelDoc2
Part;
bool
boolstatus;
public
void Main()
{
object
myFeature = null;
Body2[]
obj = new Body2[1];
Array
v = default(Array);
Part
= (ModelDoc2)swApp.ActiveDoc;
object
myModelView = null;
myModelView
= Part.ActiveView;
selMgr
= (SelectionMgr)Part.SelectionManager;
//InsertSubWeldFolder2
boolstatus
= Part.Extension.SelectByID2("Gusset1", "SOLIDBODY",
0, 0, 0, false, 0, null, 0);
obj[0]
= (Body2)selMgr.GetSelectedObject6(1, -1);
v
= obj;
fm
= Part.FeatureManager;
myFeature
= fm.InsertSubWeldFolder2(v);
Part.ClearSelection2(true);
//InsertWeldmentTrimFeature2
Body2[]
obj1 = new Body2[1];
Body2[]
obj2 = new Body2[1];
long
Options = 0;
Array
v1 = default(Array);
Array
v2 = default(Array);
boolstatus
= Part.Extension.SelectByID2("Structural Member1[2]", "SOLIDBODY",
0, 0, 0, true, 2, null, 0);
boolstatus
= Part.Extension.SelectByID2("Structural Member1[1]", "SOLIDBODY",
0, 0, 0, true, 1, null, 0);
long
Count = 0;
Count
= selMgr.GetSelectedObjectCount();
if
(Count == 2)
{
obj1[0]
= (Body2)selMgr.GetSelectedObject2(1);
v1
= obj1;
obj2[0]
= (Body2)selMgr.GetSelectedObject2(2);
v2
= obj2;
Part.ClearSelection2(true);
Options
= (long)swWeldmentTrimExtendOptionType_e.swWeldmentTrimExtendOption_AllowTrimmedExtensionTrim
+ (long)swWeldmentTrimExtendOptionType_e.swWeldmentTrimExtendOption_AllowTrimmingExtensionTrim
+ (long)swWeldmentTrimExtendOptionType_e.swWeldmentTrimExtendOption_CopedCut
+ (long)swWeldmentTrimExtendOptionType_e.swWeldmentTrimExtendOption_WeldGap;
myFeature
= fm.InsertWeldmentTrimFeature2(1,
(int)Options, 0.01, v1, v2);
}
//InsertEndCapFeature
Feature
endCapFeature = default(Feature);
Face2[]
face1 = new Face2[1];
Array
x = default(Array);
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.6023443450227,
0.6150000000001, -1.013201139555, true, 1, null, 0);
face1[0]
= (Face2)selMgr.GetSelectedObject6(1, -1);
x
= face1;
endCapFeature
= fm.InsertEndCapFeature2(0.005,
false, true, 0.003, 0.5, 0.003, x);
Part.ClearSelection2(true);
//InsertStructuralWeldment3
Array
segmentObjects = default(Array);
SketchSegment[]
sketchSegments = new SketchSegment[4];
string
profilePathName = null;
Feature
structuralMember = default(Feature);
StructuralMemberGroup
@group = default(StructuralMemberGroup);
StructuralMemberGroup[]
GroupArray1 = new StructuralMemberGroup[1];
long
i = 0;
@group
= fm.CreateStructuralMemberGroup();
Part.ClearSelection2(true);
Part.InsertSketch2(true);
segmentObjects
= (System.Array)Part.SketchManager.CreateCornerRectangle(0, 0, 0, 1.0,
2.0, 0);
for
(i = 0; i <= segmentObjects.GetUpperBound(0); i++)
{
sketchSegments[i]
= (SketchSegment)segmentObjects.GetValue(i);
}
@group.Segments
= sketchSegments;
GroupArray1[0]
= @group;
Part.ViewZoomtofit2();
Part.InsertSketch2(true);
profilePathName
= "C:\\Program Files\\SolidWorks Corp\\SolidWorks\\data\\weldment
profiles\\ansi inch\\square tube\\2 x 2 x 0.25.SLDLFP";
structuralMember
= fm.InsertStructuralWeldment3(profilePathName,
1, 0.0, false, GroupArray1);
Part.ClearSelection2(true);
//InsertGussetFeature2
Face2[]
faceGFObj = new Face2[2];
object
z = null;
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.02539999999988,
1.94542628561, 0.00429028534694, true, 1, null, 0);
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.07780718114736,
1.9746, -0.001856983219, true, 2, null, 0);
Count
= selMgr.GetSelectedObjectCount();
if
(Count == 2)
{
faceGFObj[0]
= (Face2)selMgr.GetSelectedObject6(1, 1);
faceGFObj[1]
= (Face2)selMgr.GetSelectedObject6(1, 2);
z
= faceGFObj;
Part.ClearSelection2(true);
myFeature
= fm.InsertGussetFeature2(0.005,
0, 0, false, 0.025, 0.025, 0.015, 0.7853981633975, 0.015, true,
0.005,
0, false, false, false, z);
}
//InsertFilletBeadFeature3
Face2[]
fbFaceObj1 = new Face2[1];
Face2[]
fbFaceObj2 = new Face2[2];
Part.ClearSelection2(true);
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.0412896304482,
0.02548020566445, 0, true, 1, null, 0);
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.09804264728081,
0.01499999999999, 0.0008069730266129, true, 2, null, 0);
boolstatus
= Part.Extension.SelectByID2("", "FACE", 0.01364526875011,
0.08738481720087, 0.01330055827532, true, 4, null, 0);
Count
= selMgr.GetSelectedObjectCount();
//
Face Set 1
fbFaceObj1[0]
= (Face2)selMgr.GetSelectedObject6(1, 1);
//
Face Set 2
fbFaceObj2[0]
= (Face2)selMgr.GetSelectedObject6(1, 2);
//fbFaceObj2(0)
= selMgr.GetSelectedObject6(1, 4)
v1
= fbFaceObj1;
v2
= fbFaceObj2;
Part.ClearSelection2(true);
int[]
edges = new int[1];
Array
edgeArray = default(Array);
edges[0]
= 0;
//edges(1)
= 0
edgeArray
= edges;
myFeature
= fm.InsertFilletBeadFeature3(0,
0.003, 0.003, 2, 0.003, 0.006, 0, 0.003, 0.003, 2, 0.003, 0, 1, edgeArray,
0, null, v1, v2);
Part.ClearSelection2(true);
}
public
SldWorks swApp;
}
}