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Move Assembly Components to New Folder Example (VBA)

This example shows how to move selected assembly components to a newly created folder in the FeatureManager design tree.

' Preconditions: Specified assembly document to open exists.
' Postconditions:
' 1. Assembly document is opened.
' 2. The valve<1> and valve_guide<1> components are selected.
' 3. Folder named Folder1 is created in the FeatureManager design tree.
' 4. The valve<1> and valve_guide<1> components are moved to Folder1,
'    which you can verify by expanding the Folder1 folder.
' NOTE: Because the assembly document is used by elsewhere,
' do not save any changes when closing the document.

Option Explicit


Sub Main()


        Dim swApp As SldWorks.SldWorks

        Dim modelDoc2 As SldWorks.modelDoc2

        Dim assemblyDoc As SldWorks.assemblyDoc

        Dim featureMgr As SldWorks.FeatureManager

        Dim modelDocExt As SldWorks.ModelDocExtension

        Dim selectionMgr As SldWorks.selectionMgr

        Dim feature As SldWorks.feature

        Dim selObj As Object

        Dim errors As Long

        Dim warnings As Long

        Dim status As Boolean

        Dim count As Long

        Dim componentToMove As SldWorks.Component2

        Dim componentsToMove() As Object

        Dim i As Long

        Dim retVal As Boolean


        Set swApp = CreateObject("SldWorks.Application")


        'Open assembly document

        swApp.OpenDoc6 "C:\Program Files\SolidWorks Corp\SolidWorks\samples\tutorial\motionstudies\valve_cam.sldasm", swDocASSEMBLY, swOpenDocOptions_Silent, "", errors, warnings

        Set modelDoc2 = swApp.ActiveDoc

        Set assemblyDoc = modelDoc2


        'Select and get the two valve-related components to move to the new folder

        Set modelDocExt = modelDoc2.Extension

        Set selectionMgr = modelDoc2.SelectionManager

        status = modelDocExt.SelectByID2("valve-1@valve_cam", "COMPONENT", 0, 0, 0, True, 0, Nothing, 0)

        Set selObj = selectionMgr.GetSelectedObject6(1, -1)

        status = modelDocExt.SelectByID2("valve_guide-1@valve_cam", "COMPONENT", 0, 0, 0, True, 0, Nothing, 0)

        Set selObj = selectionMgr.GetSelectedObject6(2, -1)

        count = selectionMgr.GetSelectedObjectCount2(0)

        ReDim componentsToMove(count - 1)

        For i = 0 To count - 1

            Set componentToMove = selectionMgr.GetSelectedObjectsComponent4(i + 1, 0)

            Set componentsToMove(i) = componentToMove



        'Create the folder where to move the selected components

        Set featureMgr = modelDoc2.FeatureManager

        Set feature = featureMgr.InsertFeatureTreeFolder2(swFeatureTreeFolder_EmptyBefore)

        Set feature = assemblyDoc.FeatureByName("Folder1")


        'Move the selected components to the new folder

        retVal = assemblyDoc.ReorderComponents(componentsToMove, feature, swReorderComponents_LastInFolder)


End Sub

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