Hide Table of Contents

Move Assembly Components to New Folder Example (VB.NET)

This example shows how to move selected assembly components to a newly created folder in the FeatureManager design tree.

' Preconditions: Specified assembly document to open exists.
' Postconditions:
' 1. Assembly document is opened.
' 2. The valve<1> and valve_guide<1> components are selected.
' 3. Folder named Folder1 is created in the FeatureManager design tree.
' 4. The valve<1> and valve_guide<1> components are moved to Folder1,
'    which you can verify by expanding the Folder1 folder.
' NOTE: Because the assembly document is used elsewhere,
' do not save any changes when closing the document.

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swconst

Imports System

Imports System.Runtime.InteropServices


Partial Public Class SolidWorksMacro


    Public Sub Main()


        Dim errors As Integer = 0

        Dim warnings As Integer = 0

        Dim status As Boolean = False


        'Open assembly document

        swApp.OpenDoc6("C:\Program Files\SolidWorks Corp\SolidWorks\samples\tutorial\motionstudies\valve_cam.sldasm", CInt(swDocumentTypes_e.swDocASSEMBLY), CInt(swOpenDocOptions_e.swOpenDocOptions_Silent), "", errors, warnings)

        Dim modelDoc2 As ModelDoc2 = DirectCast(swApp.ActiveDoc, ModelDoc2)

        Dim assemblyDoc As AssemblyDoc = DirectCast(modelDoc2, AssemblyDoc)

        Dim featureMgr As FeatureManager = DirectCast(modelDoc2.FeatureManager, FeatureManager)


        'Select and get the two valve-related components to move to the new folder

        Dim modelDocExt As ModelDocExtension = modelDoc2.Extension

        Dim selectionMgr As SelectionMgr = DirectCast(modelDoc2.SelectionManager, SelectionMgr)

        status = modelDocExt.SelectByID2("valve-1@valve_cam", "COMPONENT", 0, 0, 0, True, _

        0, Nothing, 0)

        Dim selObj As Object = selectionMgr.GetSelectedObject6(1, -1)

        status = modelDocExt.SelectByID2("valve_guide-1@valve_cam", "COMPONENT", 0, 0, 0, True, _

        0, Nothing, 0)

        selObj = selectionMgr.GetSelectedObject6(2, -1)

        Dim count As Integer = selectionMgr.GetSelectedObjectCount2(0)

        Dim componentsToMove As Object() = New Object(count - 1) {}

        For i As Integer = 0 To count - 1

            componentsToMove(i) = selectionMgr.GetSelectedObjectsComponent4(i + 1, 0)



        'Create the folder where to move the selected components

        Dim feature As Feature = featureMgr.InsertFeatureTreeFolder2(CInt(swFeatureTreeFolderType_e.swFeatureTreeFolder_EmptyBefore))

        feature = DirectCast(assemblyDoc.FeatureByName("Folder1"), Feature)


        'Convert .NET objects to IDispatch by using DispatchWrapper

        compsToMove = ObjectArrayToDispatchWrapperArray(componentsToMove)



        'Move the selected components to the new folder

        retVal = assemblyDoc.ReorderComponents(compsToMove, feature, CInt(swReorderComponentsWhere_e.swReorderComponents_LastInFolder))


    End Sub


    Public Function ObjectArrayToDispatchWrapperArray(ByVal SwObjects As Object()) As DispatchWrapper()

        Dim arraySize As Integer

        arraySize = SwObjects.GetUpperBound(0)

        Dim dispwrap As DispatchWrapper() = New DispatchWrapper(arraySize) {}

        Dim arrayIndex As Integer

        For arrayIndex = 0 To arraySize

            dispwrap(arrayIndex) = New DispatchWrapper(SwObjects(arrayIndex))


        Return dispwrap

    End Function


    ''' <summary>

    ''' The SldWorks swApp variable is pre-assigned for you.

    ''' </summary>

    Public swApp As SldWorks

    Public retVal As Boolean

    Public compsToMove As DispatchWrapper()


End Class


Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Move Assembly Componets to New Folder Example (VB.NET)
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: API Help (English only) 2013 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.