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Move Assembly Components to New Folder Example (VB.NET)

This example shows how to move selected assembly components to a newly created folder in the FeatureManager design tree.

'-------------------------------------------------------
' Preconditions: Specified assembly document to open exists.
'
' Postconditions:
' 1. Assembly document is opened.
' 2. The valve<1> and valve_guide<1> components are selected.
' 3. Folder named Folder1 is created in the FeatureManager design tree.
' 4. The valve<1> and valve_guide<1> components are moved to Folder1,
'    which you can verify by expanding the Folder1 folder.
'
' NOTE: Because the assembly document is used elsewhere,
' do not save any changes when closing the document.
'--------------------------------------------------------

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swconst

Imports System

Imports System.Runtime.InteropServices

 

Partial Public Class SolidWorksMacro

 

    Public Sub Main()

 

        Dim errors As Integer = 0

        Dim warnings As Integer = 0

        Dim status As Boolean = False

 

        'Open assembly document

        swApp.OpenDoc6("C:\Program Files\SolidWorks Corp\SolidWorks\samples\tutorial\motionstudies\valve_cam.sldasm", CInt(swDocumentTypes_e.swDocASSEMBLY), CInt(swOpenDocOptions_e.swOpenDocOptions_Silent), "", errors, warnings)

        Dim modelDoc2 As ModelDoc2 = DirectCast(swApp.ActiveDoc, ModelDoc2)

        Dim assemblyDoc As AssemblyDoc = DirectCast(modelDoc2, AssemblyDoc)

        Dim featureMgr As FeatureManager = DirectCast(modelDoc2.FeatureManager, FeatureManager)

 

        'Select and get the two valve-related components to move to the new folder

        Dim modelDocExt As ModelDocExtension = modelDoc2.Extension

        Dim selectionMgr As SelectionMgr = DirectCast(modelDoc2.SelectionManager, SelectionMgr)

        status = modelDocExt.SelectByID2("valve-1@valve_cam", "COMPONENT", 0, 0, 0, True, _

        0, Nothing, 0)

        Dim selObj As Object = selectionMgr.GetSelectedObject6(1, -1)

        status = modelDocExt.SelectByID2("valve_guide-1@valve_cam", "COMPONENT", 0, 0, 0, True, _

        0, Nothing, 0)

        selObj = selectionMgr.GetSelectedObject6(2, -1)

        Dim count As Integer = selectionMgr.GetSelectedObjectCount2(0)

        Dim componentsToMove As Object() = New Object(count - 1) {}

        For i As Integer = 0 To count - 1

            componentsToMove(i) = selectionMgr.GetSelectedObjectsComponent4(i + 1, 0)

        Next

 

        'Create the folder where to move the selected components

        Dim feature As Feature = featureMgr.InsertFeatureTreeFolder2(CInt(swFeatureTreeFolderType_e.swFeatureTreeFolder_EmptyBefore))

        feature = DirectCast(assemblyDoc.FeatureByName("Folder1"), Feature)

 

        'Convert .NET objects to IDispatch by using DispatchWrapper

        compsToMove = ObjectArrayToDispatchWrapperArray(componentsToMove)

        modelDoc2.ClearSelection2(True)

 

        'Move the selected components to the new folder

        retVal = assemblyDoc.ReorderComponents(compsToMove, feature, CInt(swReorderComponentsWhere_e.swReorderComponents_LastInFolder))

 

    End Sub

     

    Public Function ObjectArrayToDispatchWrapperArray(ByVal SwObjects As Object()) As DispatchWrapper()

        Dim arraySize As Integer

        arraySize = SwObjects.GetUpperBound(0)

        Dim dispwrap As DispatchWrapper() = New DispatchWrapper(arraySize) {}

        Dim arrayIndex As Integer

        For arrayIndex = 0 To arraySize

            dispwrap(arrayIndex) = New DispatchWrapper(SwObjects(arrayIndex))

        Next

        Return dispwrap

    End Function

 

    ''' <summary>

    ''' The SldWorks swApp variable is pre-assigned for you.

    ''' </summary>

    Public swApp As SldWorks

    Public retVal As Boolean

    Public compsToMove As DispatchWrapper()

 

End Class

 



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