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Create Edge Flange Example (VBA)

This example shows how to create an edge flange.




' Precconditions: Sheet metal part is open and

'                contains an edge flange. Flat pattern is suppressed.


' Postcontitions: Another edge flange is created.



Option Explicit


Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swSelMgr As SldWorks.SelectionMgr

Dim swEntity As SldWorks.Entity

Dim swModelDocExt As SldWorks.ModelDocExtension

Dim swFeat As SldWorks.Feature

Dim swEdgeFlange As SldWorks.EdgeFlangeFeatureData

Dim pNewEdge(0) As Object

Dim boolstatus As Boolean

Dim bRet As Boolean


Sub main()


    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    Set swSelMgr = swModel.SelectionManager

    Set swModelDocExt = swModel.Extension


    ' Select the edge for the new flange

    boolstatus = swModelDocExt.SelectByID2("", "EDGE", 0.06071758265887, -0.03627116313436, 0.05999086611155, False, 0, Nothing, 0)

    Set pNewEdge(0) = swSelMgr.GetSelectedObject6(1, 0)


    ' Select the sketch for the new flange

    boolstatus = swModelDocExt.SelectByID2("Sketch8", "SKETCH", 0, 0, 0, False, 0, Nothing, 0)

    Set swEntity = swSelMgr.GetSelectedObject6(1, 0)


    ' Select the existing edge flange to get the edge flange feature

    boolstatus = swModelDocExt.SelectByID2("Edge-Flange1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)

    Set swFeat = swSelMgr.GetSelectedObject6(1, 0)

    swModel.ClearSelection2 True

    Set swEdgeFlange = swFeat.GetDefinition


   ' Roll back the model to modify it

    swEdgeFlange.AccessSelections swModel, Nothing


    swEntity.Select4 True, Nothing


    Dim vEdges As Variant

    vEdges = pNewEdge

    ' Create the new flange

    swEdgeFlange.Edges = vEdges


    ' Roll forward the model with the new flange

    swFeat.ModifyDefinition swEdgeFlange, swModel, Nothing


End Sub

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