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Create Save Bodies Feature and Create an Assembly (VBA)

This example shows how to create:

  • a Save Bodies feature using a part that has been split.

  • an assembly from the split parts.

'-----------------------------------------------

' Preconditions: Part document is open and contains

'                a solid body that has been split.

'

' Postconditions: C:\temp\asd1.sldprt, C:\temp\asd2.sldprt,

'                 and C:\temp\asdf.sldasm are created. In the

'                 original part, the Split solid bodies in the

'                 Solid Bodies folder are now Save Bodies

'                 solid bodies.

'-----------------------------------------------

Option Explicit

 

Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swSelMgr As SldWorks.SelectionMgr

Dim swFeat As SldWorks.Feature

Dim swFeatMgr As SldWorks.FeatureManager

Dim swBodyFolder As SldWorks.BodyFolder

Dim v1 As Variant

Dim i As Long

Dim fileNames(1) As String

Dim fileNameVar As Variant

 

Sub GetVariantOfBody(swFeature As SldWorks.Feature, bodyList As Variant)

    Dim tt As Variant

    

    Set swBodyFolder = swFeature.GetSpecificFeature2

    Dim count As Integer

    count = swBodyFolder.GetBodyCount

    If (count < 1) Then

        MsgBox ("There are no bodies. Please create a body.")

    Else

        bodyList = swBodyFolder.GetBodies

    End If

End Sub

 

Sub main()

 

Set swApp = Application.SldWorks

Set swModel = swApp.ActiveDoc

Set swSelMgr = swModel.SelectionManager

Set swFeat = swModel.FirstFeature

Set swFeatMgr = swModel.FeatureManager

 

Dim contLoop As Boolean

contLoop = True

While Not swFeat Is Nothing And contLoop = True

    Dim Name As String

    Name = swFeat.GetTypeName2

    

    If (Name = "SolidBodyFolder") Then

        

        GetVariantOfBody swFeat, v1

        contLoop = False

    End If

    If (contLoop = True) Then

        Set swFeat = swFeat.GetNextFeature

    End If

Wend

 

fileNames(0) = "C:\temp\asd1.sldprt"

fileNames(1) = "C:\temp\asd2.sldprt"

fileNameVar = fileNames

swFeatMgr.CreateSaveBodyFeature v1, fileNameVar, "C:\temp\asdf.sldasm", True, True

 

End Sub



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Web Help Content Version: API Help (English only) 2013 SP05

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