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Insert Sweep Cut Feature Example (VB.NET)

This example shows how to create a sweep cut feature and get its properties.

'-----------------------------------------------------------------------------
' Preconditions:
' 1. Ensure that the specified document exists.
' 2. Open an Immediate Window.
'
' Postconditions:
' 1. Cut-Sweep1 is in the FeatureManager design tree.
' 2. Inspect the Immediate Window for sweep feature data.
'
' NOTE: Because this part document is used by other macros,
'       do not save any changes when closing the document.
'------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics

Partial Class SolidWorksMacro

    
Dim Part As ModelDoc2
    
Dim boolstatus As Boolean
    Dim longstatus As Long, longwarnings As Long
    Dim swSweep As SweepFeatureData
    
Dim swProfFeat As Feature
    
Dim swProfSketch As Sketch
    
Dim swPathFeat As Feature
    
Dim swPathSketch As Sketch
    
Dim bRet As Boolean

    Public Enum swTangencyType_e
        swTangencyNone = 0
        swTangencyNormalToProfile = 1
        swTangencyDirectionVector = 2
        swTangencyAllFaces = 3
    
End Enum

    Public Enum swThinWallType_e
        swThinWallOneDirection = 0
        swThinWallOppDirection = 1
        swThinWallMidPlane = 2
        swThinWallTwoDirection = 3
    
End Enum

    Public Enum swTwistControlType_e
        swTwistControlFollowPath = 0
        swTwistControlKeepNormalConstant = 1
        swTwistControlFollowPathFirstGuideCurve = 2
        swTwistControlFollowFirstSecondGuideCurves = 3
    
End Enum

    Public Enum swCutSweepOption_e
        swProfileSweep = 1
        swSolidSweep = 2
    
End Enum


    Sub main()

        Part = swApp.OpenDoc6(
"C:\program files\SolidWorks Corp\SolidWorks\samples\tutorial\api\sweepcutextrude.SLDPRT", 1, 0, "", longstatus, longwarnings)
        swApp.ActivateDoc2(
"sweepcutextrude.SLDPRT", False, longstatus)
        Part = swApp.ActiveDoc
        
Dim myModelView As Object
        myModelView = Part.ActiveView
        myModelView.FrameLeft = 0
        myModelView.FrameTop = 0

        myModelView.FrameState = swWindowState_e.swWindowMaximized
        Part.ShowNamedView2(
"*Isometric", 7)

        boolstatus = Part.Extension.SelectByID2(
"Sketch2", "SKETCH", 0.01948983274156, -0.02564816935317, 0, False, 1, Nothing, 0) ' profile has Mark = 1
        boolstatus = Part.Extension.SelectByID2("Sketch3", "SKETCH", -0.03797488317814, -0.02133214444164, 0, True, 4, Nothing, 0) ' path sweep has Mark = 4
        Dim myFeature As Feature
        myFeature = Part.FeatureManager.InsertCutSwept4(
False, True, 0, False, False, 0, 0, False, 0, 0, 0, 0, True, True, 0, True, True, True, False)

        swSweep = myFeature.GetDefinition
        swProfFeat = swSweep.Profile : Debug.Assert(
Not Nothing Is swProfFeat)
        swProfSketch = swProfFeat.GetSpecificFeature : Debug.Assert(
Not Nothing Is swProfSketch)

        
' Rollback to access selections
        bRet = swSweep.AccessSelections(Part, Nothing) : Debug.Assert(bRet)

        swPathFeat = swSweep.Path : Debug.Assert(
Not Nothing Is swPathFeat)
        swPathSketch = swPathFeat.GetSpecificFeature : Debug.Assert(
Not Nothing Is swPathSketch)

        Debug.Print(
"File = " & Part.GetPathName)
        Debug.Print(
"  " & myFeature.Name)
        Debug.Print(
"    Path                      = " & swPathFeat.Name)
        Debug.Print(
"    Path alignment type       = " & swSweep.PathAlignmentType) 'swTangencyType_e
        Debug.Print("    Profile                   = " & swProfFeat.Name)
        Debug.Print(
"    AdvancedSmoothing         = " & swSweep.AdvancedSmoothing)
        Debug.Print(
"    AlignWithEndFaces         = " & swSweep.AlignWithEndFaces)
        Debug.Print(
"    AutoSelect                = " & swSweep.AutoSelect)
        Debug.Print(
"    AutoSelectComponents      = " & swSweep.AutoSelectComponents)
        Debug.Print(
"    EndTangencyType           = " & swSweep.EndTangencyType)   'swTangencyType_e
        Debug.Print("    AssemblyFeatureScope      = " & swSweep.AssemblyFeatureScope)
        Debug.Print(
"    FeatureScope              = " & swSweep.FeatureScope)
        Debug.Print(
"    FeatureScopeBodiesCnt     = " & swSweep.GetFeatureScopeBodiesCount)
        Debug.Print(
"    GetPathType               = " & swSweep.GetPathType)       'swSelectType_e
        Debug.Print("    Wall thickness foward     = " & swSweep.GetWallThickness(True) * 1000.0# & " mm")
        Debug.Print(
"    Wall thickness reverse    = " & swSweep.GetWallThickness(False) * 1000.0# & " mm")
        Debug.Print(
"    IsBossFeature             = " & swSweep.IsBossFeature)
        Debug.Print(
"    IsThinFeature             = " & swSweep.IsThinFeature)
        Debug.Print(
"    MaintainTangency          = " & swSweep.MaintainTangency)
        Debug.Print(
"    Merge                     = " & swSweep.Merge)
        Debug.Print(
"    MergeSmoothFaces          = " & swSweep.MergeSmoothFaces)
        Debug.Print(
"    PropagateFeatureToParts   = " & swSweep.PropagateFeatureToParts)
        Debug.Print(
"    StartTangencyType         = " & swSweep.StartTangencyType) 'swTangencyType_e
        Debug.Print("    TangentPropagation        = " & swSweep.TangentPropagation)
        Debug.Print(
"    ThinWallType              = " & swSweep.ThinWallType)
        Debug.Print(
"    TwistControlType          = " & swSweep.TwistControlType)  'swTwistControlType_e
        Debug.Print("    CutSweepOption            = " & swSweep.GetCutSweepOption)  'swCutSweepOption_e

        ' Roll forward
        swSweep.ReleaseSelectionAccess()

    
End Sub
  
    
Public swApp As SldWorks

End Class

 



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