Insert and Show BOM Table and BOM Balloon Example (C#)

This example shows how to insert a bill of materials table and balloon in a drawing document.

//----------------------------------------------------------------------------
// Preconditions: Specified file to open and template exist.
//
// Postconditions:
// 1. An indented BOM table is inserted.
// 2. A BOM balloon annotation is inserted.
// 3. Inspect the Immediate Window for the name of the configuration used
//    to create the table, the type of numbering, and the name of the annotation.
//
// NOTE: Because this drawing document is used elsewhere,
// do not save any changes when closing the document.
//------------------------------------------------------------------
 
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
 
namespace IViewInsertBomTable4CSharp.csproj
{
 
    partial class SolidWorksMacro
    {
 
 
        public void Main()
        {
            ModelDoc2 swModel = default(ModelDoc2);
            ModelDocExtension swModelDocExt = default(ModelDocExtension);
            DrawingDoc swDrawing = default(DrawingDoc);
            View swView = default(View);
            BomTableAnnotation swBOMAnnotation = default(BomTableAnnotation);
            BomFeature swBOMFeature = default(BomFeature);
            Note swNote = default(Note);
            BalloonOptions BomBalloonParams = default(BalloonOptions);
            bool boolstatus = false;
            int AnchorType = 0;
            int NbrType = 0;
            int BomType = 0;
            int nErrors = 0;
            int nWarnings = 0;
            string Configuration = null;
            string TableTemplate = null;
 
            swModel = (ModelDoc2)swApp.OpenDoc6("c:\\Program Files\\SolidWorks Corp\\SolidWorks\\samples\\tutorial\\advdrawings\\foodprocessor.slddrw", (int)swDocumentTypes_e.swDocDRAWING, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref nErrors, ref nWarnings);
            swDrawing = (DrawingDoc)swModel;
            swModelDocExt = (ModelDocExtension)swModel.Extension;
            boolstatus = swDrawing.ActivateView("Drawing View1");
            swView = (View)swDrawing.ActiveDrawingView;
 
            // Insert parts-only BOM table
            AnchorType = (int)swBOMConfigurationAnchorType_e.swBOMConfigurationAnchor_TopLeft;
            BomType = (int)swBomType_e.swBomType_Indented;
            NbrType = (int)swNumberingType_e.swNumberingType_Detailed;
            TableTemplate = "C:\\Program Files\\SolidWorks Corp\\SolidWorks\\lang\\english\\bom-standard.sldbomtbt";
            Configuration = "";
            swBOMAnnotation = (BomTableAnnotation)swView.InsertBomTable4(false, 0.4, 0.3, AnchorType, BomType, Configuration, TableTemplate, false, NbrType, true);
            swBOMFeature = (BomFeature)swBOMAnnotation.BomFeature;
 
            Debug.Print("Type of BOM table as defined in swBomType_e: " + (int)swBOMFeature.TableType);
	   Debug.Print("Numbering type of BOM table as defined in swNumberingType_e: " + (int)swBOMFeature.NumberingTypeOnIndentedBOM);
            Debug.Print("Value to display when a value is 0 as defined in swZeroQuantityDisplay_e: " + (int)swBOMFeature.ZeroQuantityDisplay);
 
            // Print the name of the configuration used for the BOM table
            Debug.Print("Name of configuration used for BOM table: " + swBOMFeature.Configuration);
	   Debug.Print("Display as one item? " + swBOMFeature.DisplayAsOneItem);
	   Debug.Print("Strikeout missing items? " + swBOMFeature.StrikeoutMissingItems);
	   Debug.Print("Sequence start number: " + swBOMFeature.SequenceStartNumber);
	   Debug.Print("Keep missing items? " + swBOMFeature.KeepMissingItems);
	   Debug.Print("Keep current item numbers? " + swBOMFeature.KeepCurrentItemNumbers);
 
            boolstatus = swModelDocExt.SelectByID2("", "EDGE", 0.1205506330468, 0.261655309417, -0.0004000000000133, false, 0, null, 0);
 
 
            BomBalloonParams = swModelDocExt.CreateBalloonOptions();
            BomBalloonParams.Style = (int)swBalloonStyle_e.swBS_Circular;
            BomBalloonParams.Size = (int)swBalloonFit_e.swBF_2Chars;
            BomBalloonParams.UpperTextContent = (int)swBalloonTextContent_e.swBalloonTextItemNumber;
            BomBalloonParams.UpperText = "";
            BomBalloonParams.ShowQuantity = true;
            BomBalloonParams.QuantityPlacement = (int)swBalloonQuantityPlacement_e.swBalloonQuantityPlacement_Right;
            BomBalloonParams.QuantityDenotationText = "PLACES";
            BomBalloonParams.QuantityOverride = false;
            BomBalloonParams.QuantityOverrideValue = "";
            BomBalloonParams.ItemNumberStart = 1;
            BomBalloonParams.ItemNumberIncrement = 1;
            BomBalloonParams.ItemOrder = (int)swBalloonItemNumbersOrder_e.swBalloonItemNumbers_DoNotChangeItemNumbers;
 
 
            swNote = (Note)swModelDocExt.InsertBOMBalloon2(BomBalloonParams);
 
 
            // Get whether balloon is a BOM balloon
            // If so, print the name of the BOM balloon
 
            if (swNote.IsBomBalloon())
            {
                Debug.Print("Name of BOM balloon: " + swNote.GetName());
            }
 
            swDrawing.ForceRebuild();
 
        }
 
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
 
        public SldWorks swApp;
 
    }
}