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Loft with Guide Curve and Non-Planar Profile

You can create a guide curve loft by using two or more profiles and one or more guide curves to connect the profiles. The profiles can be either planar or non-planar. The guide curves help you control the intermediate profiles that are generated.

To create a loft using guide curves and non-planar profiles:

  1. Use a split line to create a non-planar profile on a model face.
  2. Sketch one or more guide curves.
  3. Add a Pierce relation between the guide curves and an edge or vertex on the non-planar face.
  4. Sketch the remaining profiles needed to create the loft.
  5. Add relations between the profiles and guide curves:
    • Pierce relations between the guide curves and vertices, user-defined sketch points, or both, on the profiles.
    • Coincident relations between vertices, user-defined sketch points, or both, of the guide curves and the profiles.

    Non-planar profile with split line and guide curve
    Non-planar profile with split line and guide curve leading to planar profile

  6. Click one of the following:
    • Lofted Boss/Base (Features toolbar) or Insert > Boss/Base > Loft
    • Lofted Cut (Features toolbar) or Insert > Cut > Loft
    • Lofted Surface (Surfaces toolbar) or Insert > Surface > Loft
  7. In the PropertyManager:
    1. Select the profiles to loft in the graphics area for Profiles .

      To select the profile sketch on the non-planar face, you must use the Select Group tool in the SelectionManager to select the individual profile sketch edges.

    2. Set the PropertyManager options.
  8. Click .


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