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Change Bend Radius of Sheet Metal Part Example (VBA)

This example shows how to change the default bend radius of a sheet metal part.




' Preconditions:

'       (1) Part document containing sheet metal part is open.

'       (2) Sheet-Metal feature is selected.


' Postconditions: Default bend radius value is doubled.



Option Explicit


Sub main()

    Dim swApp                   As SldWorks.SldWorks

    Dim swModel                 As SldWorks.ModelDoc2

    Dim swSelMgr                As SldWorks.SelectionMgr

    Dim swFeat                  As SldWorks.feature

    Dim swSheetMetal            As SldWorks.SheetMetalFeatureData

    Dim bRet                    As Boolean

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    Set swSelMgr = swModel.SelectionManager

    Set swFeat = swSelMgr.GetSelectedObject5(1)

    Set swSheetMetal = swFeat.GetDefinition


    Debug.Print "Feature = " & swFeat.Name

    Debug.Print "  BendRadius = " & swSheetMetal.BendRadius * 1000# & " mm"


    ' Rollback to change default bend radius

    bRet = swSheetMetal.AccessSelections(swModel, Nothing): Debug.Assert bRet


    ' Double the default bend radius value

    swSheetMetal.BendRadius = 2# * swSheetMetal.BendRadius


    ' Apply changes

    bRet = swFeat.ModifyDefinition(swSheetMetal, swModel, Nothing): Debug.Assert bRet

End Sub


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