Insert Hole Wizard Slot and Hole Example (VB.NET)
This example shows how to use
IFeatureManager::HoleWizard5
to insert a straight slot and a counterbore hole in a part.
'-----------------------------------------------
' Preconditions:
' 1. Specified part document to open exists.
' 2. Open the Immediate window.
'
' Postconditions:
' 1. Opens the specified part document.
' 2. Creates a straight slot and a counterbore hole.
' 3. Prints the length of the slot to the Immediate
' window.
' 4. To verify steps 2 and 3, examine the part in the
' graphics area, the FeatureManager design tree,
' and the Immediate window.
'
' NOTE: Because the part document is used elsewhere,
' do not save any changes when closing it.
'------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics
Partial Class SolidWorksMacro
Public Sub main()
Dim swModel As ModelDoc2
Dim swFeatureMgr As FeatureManager
Dim swFeature As Feature
Dim swModelDocExt As ModelDocExtension
Dim fileName As String
Dim errors As Integer
Dim warnings As Integer
Dim status As Boolean
Dim SlotType As Integer
Dim HoleType As Integer
Dim StandardIndex As Integer
Dim FastenerTypeIndex As Integer
Dim SSize As String
Dim EndType As Integer
Dim ConvFactorLength As Double
Dim ConvFactorAngle As Double
Dim Diameter As Double
Dim Depth As Double
Dim Length As Double
Dim ScrewFit As Double
Dim DrillAngle As Double
Dim NearCsinkDiameter As Double
Dim NearCsinkAngle As Double
Dim FarCsinkDiameter As Double
Dim FarCsinkAngle As Double
Dim Offset As Double
Dim ThreadClass As String
Dim CounterBoreDiameter As Double
Dim CounterBoreDepth As Double
Dim HeadClearance As Double
Dim BotCsinkDiameter As Double
Dim BotCsinkAngle As Double
Dim swWizardHoleFeatData As WizardHoleFeatureData2
fileName = "C:\Program Files\SolidWorks Corp\SolidWorks\samples\tutorial\api\block20.sldprt"
swModel = swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
swFeatureMgr = swModel.FeatureManager
swModelDocExt = swModel.Extension
'Use IFeatureManager::HoleWizard5
'to create a slot
'Select the face where to create the slot
status = swModelDocExt.SelectByID2("", "FACE", -0.000609805077203873, 0.0396239999998897, -0.00830387834611201, False, 0, Nothing, 0)
SlotType = swWzdGeneralHoleTypes_e.swWzdHoleSlot
StandardIndex = swWzdHoleStandards_e.swStandardAnsiInch
FastenerTypeIndex = swWzdHoleStandardFastenerTypes_e.swStandardAnsiInchAllDrillSizes
SSize = "#97"
EndType = swEndConditions_e.swEndCondBlind
ConvFactorLength = 25.4 / 1000 'Convert inches to meters
ConvFactorAngle = (22 / 7) / 180 'Convert degrees to radians
Diameter = 0.5 * ConvFactorLength
Depth = 2 * ConvFactorLength
Length = 3 * ConvFactorLength
'Value1 to Value7 arguments; SolidWorks
'ignores parameters set to -1
ScrewFit = -1 'Value1
DrillAngle = 100 * ConvFactorAngle 'Value2
NearCsinkDiameter = -1 'Value3
NearCsinkAngle = -1 'Value4
FarCsinkDiameter = -1 'Value5
FarCsinkAngle = -1 'Value6
Offset = -1 'Value7
ThreadClass = ""
swFeature = swFeatureMgr.HoleWizard5(SlotType, StandardIndex, FastenerTypeIndex, SSize, EndType, _
Diameter, Depth, Length, ScrewFit, DrillAngle, NearCsinkDiameter, NearCsinkAngle, _
FarCsinkDiameter, FarCsinkAngle, Offset, -1, -1, -1, -1, -1, ThreadClass, _
False, False, False, False, False, False)
'Print length of slot to Immediate window
swWizardHoleFeatData = swFeature.GetDefinition
Debug.Print("Length of slot: " & swWizardHoleFeatData.Length & " inches")
'Use IFeatureManager::HoleWizard5
'to create a counterbore hole
'Select the face where to create the hole
status = swModelDocExt.SelectByID2("", "FACE", -0.0060197480091233, 0.0396239999998329, 0.0270812377555103, False, 0, Nothing, 0)
HoleType = swWzdGeneralHoleTypes_e.swWzdCounterBore
StandardIndex = swWzdHoleStandards_e.swStandardAnsiInch
FastenerTypeIndex = swWzdHoleStandardFastenerTypes_e.swStandardAnsiInchBinding
SSize = "#12"
EndType = swEndConditions_e.swEndCondThroughAll
ConvFactorLength = 25.4 / 1000 'Convert inches to meters
ConvFactorAngle = (22 / 7) / 180 'Convert degrees to radians
Diameter = 0.5 * ConvFactorLength
Depth = -1
Length = -1
'Value1 to Value12 arguments; SolidWorks
'ignores parameters set to -1
CounterBoreDiameter = 0.6 * ConvFactorLength 'Value1
CounterBoreDepth = 0.2 * ConvFactorLength 'Value2
HeadClearance = -1 'Value3
ScrewFit = -1 'Value4
DrillAngle = -1 'Value5
NearCsinkDiameter = -1 'Value6
NearCsinkAngle = -1 'Value7
BotCsinkDiameter = -1 'Value8
BotCsinkAngle = -1 'Value9
FarCsinkDiameter = -1 'Value10
FarCsinkAngle = -1 'Value11
Offset = -1 'Value12
ThreadClass = ""
swFeature = swFeatureMgr.HoleWizard5(HoleType, StandardIndex, FastenerTypeIndex, SSize, EndType, _
Diameter, Depth, Length, CounterBoreDiameter, CounterBoreDepth, HeadClearance, ScrewFit, DrillAngle, _
NearCsinkDiameter, NearCsinkAngle, BotCsinkDiameter, BotCsinkAngle, FarCsinkDiameter, FarCsinkAngle, Offset, _
ThreadClass, False, False, False, False, False, False)
End Sub
''' <summary>
''' The SldWorks swApp variable is pre-assigned for you.
''' </summary>
Public swApp As SldWorks
End Class