An assembly and its components may go through many revisions during the course of a design cycle. This is especially true in a multi-user environment where several users can work on the individual parts and subassemblies. A safe, efficient way to update the assembly is to replace the components as needed.
- You can replace a part with a subassembly or vice versa.
- You can replace one, more than one, or all instances of a component at the same time.
- You can replace a component with another that has the same name and type but comes from a different folder.
To replace one or more components:
- Do one of the following:
- Click Replace Components
(Assembly toolbar).
- Click
- Right-click a component and select Replace Components.
- Set options as described below, then click
.
The selected component instances are replaced.
If you chose Manually select, choose the configuration to open in the Configurations dialog box.
If you selected Re-attach mates, the Mated Entities PropertyManager appears. Additionally, a window shows a view of the original component with the missing mate entity highlighted, and the Missing Entities popup toolbar appears.
Selections
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Replace these component(s) |
Select the components to replace. Select All instances to replace all instances of the selected component.
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With this one |
Displays a list of open files. Select from the list or click Browse to locate the replacement component.
|
Options
| Configuration |
Select one of the following:
|
Match name
|
The software tries to match the configuration name of the old component with a configuration in the replacement component.
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Manually select
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Enables you to select the matching configuration in the replacement component.
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| Re-attach mates |
The software tries to re-attach existing mates to the replacement component.
If the old component has a mate that includes a named entity, and the replacement component has a corresponding entity with the same name, the software uses the corresponding entity when re-attaching the mate. You assign names to entities in the Entity Property dialog box. To access face and edge names in a lightweight component, either resolve the component or save the assembly in SolidWorks 2012 or later.
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