Expand IntroductionIntroduction
Expand AdministrationAdministration
Expand User InterfaceUser Interface
Expand SOLIDWORKS FundamentalsSOLIDWORKS Fundamentals
Expand Moving from 2D to 3DMoving from 2D to 3D
Expand AssembliesAssemblies
Expand CircuitWorksCircuitWorks
Expand ConfigurationsConfigurations
Expand SOLIDWORKS CostingSOLIDWORKS Costing
Expand Design CheckerDesign Checker
Expand Design Studies in SOLIDWORKSDesign Studies in SOLIDWORKS
Collapse Detailing and DrawingsDetailing and Drawings
Detailing Overview
Setting Detailing Options
Model Items
Model Items PropertyManager
Expand eDrawings MarkupseDrawings Markups
Expand StyleStyle
Add or Update a Style
Expand AnnotationsAnnotations
Expand TablesTables
Expand Bill of Materials (BOM)Bill of Materials (BOM)
Expand Drafting StandardsDrafting Standards
Expand Print SettingsPrint Settings
Collapse DrawingsDrawings
Drawings Overview
Expand Getting Started in DrawingsGetting Started in Drawings
Expand Types of Drawing DocumentsTypes of Drawing Documents
Expand Standard Drawing ViewsStandard Drawing Views
Expand Derived Drawing ViewsDerived Drawing Views
Multiple Views PropertyManager
Convert View to Sketch PropertyManager
Expand Drawing View Alignment and DisplayDrawing View Alignment and Display
DrawCompare
Drawing Statistics
Printing Drawings
Send Mail
Expand Title Block ManagementTitle Block Management
Collapse Dimensions in DrawingsDimensions in Drawings
Formatting Dimensions in Drawings
Dimensions Display Options
Hide/Show Annotations
Expand Highlighting Changed DimensionsHighlighting Changed Dimensions
Inserting Dimensions into Drawings
Dimension Type
Document Properties - Dimensions
Dimension Other PropertyManager
Dimension Value PropertyManager
Dimension Precision
Expand Aligning Dimensions and NotesAligning Dimensions and Notes
Scan Equal
Rapid Dimension
Expand Autodimension a DrawingAutodimension a Drawing
DimXpert
Dimension PropertyManager
Adding Parallel Dimensions to Drawings
Reference Dimensions
Reference Center of Mass in Drawings
Using Parentheses on Particular Dimensions
Baseline Dimensions
Expand Ordinate DimensionsOrdinate Dimensions
Expand Angular Running Dimensions Angular Running Dimensions
Chamfer Dimensions
Expand Tolerance and PrecisionTolerance and Precision
Moving and Copying Dimensions
Modify Dimension
Deleting Dimensions
Expand Dimension PaletteDimension Palette
Expand Dimension Extension LinesDimension Extension Lines
Collapse Dimension LeadersDimension Leaders
Overriding the Alignment of Dimension Text
Dimension Leaders PropertyManager
Setting Multiple Jogs in Dimension Leaders
Setting Multiple Jogs in Hole Callout Leaders
Example: Dimension Scheme Types
Dimensioning to Midpoints
Automatically Finding Virtual Sharps for Dimensions
Expand DFMXpressDFMXpress
Expand DriveWorksXpressDriveWorksXpress
Expand FloXpressFloXpress
Expand SLDXML Data ExchangeSLDXML Data Exchange
Expand Import and ExportImport and Export
Expand Model DisplayModel Display
Expand Mold DesignMold Design
Expand Motion StudiesMotion Studies
Expand Parts and FeaturesParts and Features
Expand RoutingRouting
Expand Sheet MetalSheet Metal
Expand SimulationSimulation
Expand SimulationXpressSimulationXpress
Expand SketchingSketching
Expand Sustainability ProductsSustainability Products
Expand SOLIDWORKS MBDSOLIDWORKS MBD
Expand SOLIDWORKS UtilitiesSOLIDWORKS Utilities
Expand TolerancingTolerancing
Expand TolAnalystTolAnalyst
Expand ToolboxToolbox
Expand WeldmentsWeldments
Expand Workgroup PDMWorkgroup PDM
Expand TroubleshootingTroubleshooting
Glossary
Hide Table of Contents

Dimension Leaders PropertyManager

In the Dimension Leaders PropertyManager, you can specify the display of dimensions.

To open this PropertyManager:

Select one or more dimensions, then click Leaders in the Dimension PropertyManager.

If you select multiple dimensions, only the properties that apply to all the selected dimensions are available.

Witness/Leader Display

The type of arrows and leaders available depends on the type of dimension selected. See Example: Dimension Line Terminology.

Arrow Placement You can specify placement of arrows with respect to the dimension extension lines: Outside PM_arrow_outside_dim.gif, Inside PM_arrow_inside_dim.gif, Smart PM_arrow_smart_dim.gif, Directed Leader PM_Directed_Leader.gif.

Smart specifies that arrows automatically appear outside of extension lines if the space is too small to accommodate the dimension text and the arrowheads.

A Directed Leader can be oriented at any angle with respect to the surface of the feature and can be placed in an annotation plane parallel to the feature axis.
leader_directed.gif

Circular arrowhead handles dim_arrow_handle_circle.gif appear on dimension arrows when you select dimensions. The pointer changes to Pointer_Arrowhead_Direction.gif when it is over the arrowhead handles. When you click on arrowhead handle (either handle if there are two for the dimension), the arrows flip outside or inside.

Ordinate chain Select to chain ordinate dimensions. See Example: Dimension Scheme Types.
Style You can choose separate styles for each arrow when there are two arrows for a dimension. This feature supports the JIS dimensioning standard. Two lists appear in the Dimension PropertyManager only when separate styles are specified by the dimensioning standard.
Radius PM_Radius_WitnessLeader.gif Specifies that the dimension on an arc or circle displays the radius.
dim_radial.gif
Diameter PM_Diameter_WitnessLeader.gif Specifies that the dimension on an arc or circle displays the diameter.
dim_diameter.gif
Linear PM_Linear_WitnessLeader.gif Specifies the display of a diameter dimension as a linear dimension (not radial).
DIAM_LIN.gif DIAM_RAD.gif
Linear Radial
Foreshortened PM_Foreshortened_WitnessLeader.gif Specifies that the radius dimension line is foreshortened (broken). This is helpful when the centerpoint of a radius is outside of the drawing or interferes with another drawing view. See Document Properties - Diameter Dimensions.

Use the dimension handles to reposition the center and bends.
dim_foreshortened.gif

If you move a diameter dimension into a view where it does not fit, it is foreshortened. dim_foreshortened2.gif
When you dimension to a foreshortened radius or diameter, the dimension also appears as a zigzag.
Solid Leader PM_OneArrowSolidLeader.gif Specifies the display of a solid line across the circle for radial dimensions. Not available with ANSI standard.
SLDLDR1.gif
Open Leader PM_OneArrowOpenLeader.gif  
One Arrow / Solid Leader PM_OneArrowSolidLeader.gif  
One Arrow / Open Leader PM_OneArrowOpenLeader.gif  
Two Arrows / Solid Leader PM_TwoArrowsSolidLeader.gif  
Two Arrows / Open Leader PM_TwoArrowsOpenLeader.gif  
Perpendicular to Axis PM_PerpendicularToAxis.gif (Available if you select Linear PM_Linear_WitnessLeader.gif for a radial dimension)
Perp_To_Axis.gif
Multi-jog Leader PM_dim_Leader_Multijog.gif (Available for diameter, radius, and chamfer dimensions and hole callouts) See Setting Multiple Jogs in Dimension Leaders.
DIM_Leader_PM_multijogleader.gif
Parallel to Axis PM_ParallelToAxis_WitnessLeader.gif (Available if you select Linear PM_Linear_WitnessLeader.gif for a radial dimension)
Parallel_To_Axis.gif
Dimension to inside of arc Specifies that the dimension arrow is inside the arc. Use this option in combination with the Arrows setting (either Inside or Outside) to meet your drawing standards.
Dimension_Inside_Arc.gif Dimension_Outside_Arc.gif
Dimension to inside ON

Arrows set to outside

Dimension to inside OFF

Arrows set to outside

Use document second arrow Specifies that a diameter dimension (not displayed as linear) with outside arrows follows the document default setting for a second arrow.
To specify the document default setting, select Display second outside arrow in one of the following: To override the document default, clear Use document second arrow, then select Display second outside arrow to turn the arrow display on or off.
2NDARO1.gif 2NDARO2.gif
Second arrow ON Second arrow OFF
Use document bend length Uses the value for Bent leader length in Document Properties - Dimensions. When cleared, you can specify the dimension bent leader length. Enter a value in the box.
Extend bent leader to text If selected, this option specifies that shoulders of bent leaders for radius, diameter, chamfer, and hole callouts meet and align with the end of the text in the appropriate line of text.
  • Left- and right-sided leaders set to Top Justify center to the top line of text in the dimension.
    leader-left-left-top.png leader-right-top.png
  • Left- and right-sided leaders set to Bottom Justify center to the bottom line of text in the dimension.
    leader-left-right-bottom.png leader-right-bottom.png

If this option is cleared, the shoulders of bent leaders stop at the dimension text bounding box.
leader-left-top-legacy.png

To set a default option, click Tools > Options > Document Properties > Dimensions. Under Bent leaders, select Extend to text.

Break Lines

Break Lines Select for the dimension and extension lines to break when crossing other dimension or extension lines in drawings.
You can choose for the extension lines to break only when crossing arrowheads. See Document Properties - Dimensions and select Break only around dimension arrows.
break_lines_selected.gif
Selected
break_lines_cleared.gif
Cleared
When the dimension lines are broken, they break around lines that are nearby. If a dimension is moved significantly, it may not break around the new nearby dimensions. To update the display, unbreak the dimension lines and then break them again.
Use document gap Uses the value in Document Properties - Dimensions.
Gap Enter a value if you do not use the document default.
Break extension lines Breaks extension lines around dimension lines and other extension lines.
break-extension-lines-only.gif
Break dimension line Breaks the dimension line around other dimension lines and other extension lines.
break-dimension-lines-only.gif

Custom Text Position

  Radial Dimension Text
Solid Leader, Aligned Text PM_SolidLeader_AlignedText.gif
Broken Leader, Horizontal Text PM_BrokenLeader_HorizText.gif
Broken Leader, Aligned Text PM_BrokenLeader_AlignedText.gif

Arc Condition

You can set how to dimension between arcs or circles.

First or Second arc condition Select Center, Min, or Max.
When you are dimensioning distances to arcs or circles, the following options are available:
  • First Arc Condition specifies where on the arc or circle the distance is measured.
  • Second Arc Condition specifies where on the second item the distance is measured, when both items are arcs or circles.
In these examples, the First arc condition is Center, and the Second arc condition is set as noted.
DIM2CIR1.gif DIM2CIR2.gif DIM2CIR3.gif
Center (default) Min (closest point) Max (farthest point)


Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Dimension Leaders PropertyManager
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: SOLIDWORKS 2015 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.