Insert Sweep Cut Feature Example (C#)

This example shows how to create a sweep cut feature and get its properties.

//-----------------------------------------------------------------------------
// Preconditions:
// 1. Ensure that the specified document exists.
// 2. Ensure that the namespace of this macro matches your C# project name.
// 3. Open an Immediate Window.
//
// Postconditions:
// 1. Cut-Sweep1 is in the FeatureManager design tree.
// 2. Inspect the Immediate Window for sweep feature data.
//
// NOTE: Because this part document is used by other macros,
//       do not save any changes when closing the document.
//------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
using System.Diagnostics;
namespace InsertSweepCut_CSharp.csproj
{
    partial class SolidWorksMacro
    {

        ModelDoc2 Part;
        bool boolstatus;
        int longstatus;
        int longwarnings;
        SweepFeatureData swSweep;
        Feature swProfFeat;
        Sketch swProfSketch;
        Feature swPathFeat;
        Sketch swPathSketch;
        bool bRet;

        public enum swTangencyType_e
        {
            swTangencyNone = 0,
            swTangencyNormalToProfile = 1,
            swTangencyDirectionVector = 2,
            swTangencyAllFaces = 3
        }

        public enum swThinWallType_e
        {
            swThinWallOneDirection = 0,
            swThinWallOppDirection = 1,
            swThinWallMidPlane = 2,
            swThinWallTwoDirection = 3
        }

        public enum swTwistControlType_e
        {
            swTwistControlFollowPath = 0,
            swTwistControlKeepNormalConstant = 1,
            swTwistControlFollowPathFirstGuideCurve = 2,
            swTwistControlFollowFirstSecondGuideCurves = 3
        }

        public enum swCutSweepOption_e
        {
            swProfileSweep = 1,
            swSolidSweep = 2
        }


        public void Main()
        {

            Part = swApp.OpenDoc6("C:\\Program Files\\SOLIDWORKS Corp\\SOLIDWORKS\\samples\\tutorial\\api\\sweepcutextrude.SLDPRT", 1, 0, "", ref longstatus, ref longwarnings);
            swApp.ActivateDoc2("sweepcutextrude.SLDPRT", false, ref longstatus);
            Part = (ModelDoc2)swApp.ActiveDoc;
            ModelView myModelView = null;
            myModelView = (ModelView)Part.ActiveView;
            myModelView.FrameLeft = 0;
            myModelView.FrameTop = 0;

            myModelView.FrameState = (int)swWindowState_e.swWindowMaximized;
            Part.ShowNamedView2("*Isometric", 7);

            boolstatus = Part.Extension.SelectByID2("Sketch2", "SKETCH", 0.01948983274156, -0.02564816935317, 0, false, 1, null, 0);
            // profile has Mark = 1
            boolstatus = Part.Extension.SelectByID2("Sketch3", "SKETCH", -0.03797488317814, -0.02133214444164, 0, true, 4, null, 0);
            // path sweep has Mark = 4
            Feature myFeature = default(Feature);
            myFeature = Part.FeatureManager.InsertCutSwept4(false, true, 0, false, false, 0, 0, false, 0, 0,
            0, 0, true, true, 0, true, true, true, false);

            swSweep = (SweepFeatureData)myFeature.GetDefinition();
            swProfFeat = (Feature)swSweep.Profile;
            Debug.Assert((null != swProfFeat));
            swProfSketch = (Sketch)swProfFeat.GetSpecificFeature();
            Debug.Assert((null != swProfSketch));

            // Rollback to access selections
            bRet = swSweep.AccessSelections(Part, null);
            Debug.Assert(bRet);

            swPathFeat = (Feature)swSweep.Path;
            Debug.Assert((null != swPathFeat));
            swPathSketch = (Sketch)swPathFeat.GetSpecificFeature();
            Debug.Assert((null != swPathSketch));

            Debug.Print("File = " + Part.GetPathName());
            Debug.Print(" " + myFeature.Name);
            Debug.Print(" Path = " + swPathFeat.Name);

            //swTangencyType_e
            Debug.Print(" Path alignment type = " + swSweep.PathAlignmentType);

            Debug.Print(" Profile = " + swProfFeat.Name);
            Debug.Print(" AdvancedSmoothing = " + swSweep.AdvancedSmoothing);
            Debug.Print(" AlignWithEndFaces = " + swSweep.AlignWithEndFaces);
            Debug.Print(" AutoSelect = " + swSweep.AutoSelect);
            Debug.Print(" AutoSelectComponents = " + swSweep.AutoSelectComponents);

            //swTangencyType_e
            Debug.Print(" EndTangencyType = " + swSweep.EndTangencyType);

            Debug.Print(" AssemblyFeatureScope = " + swSweep.AssemblyFeatureScope);
            Debug.Print(" FeatureScope = " + swSweep.FeatureScope);
            Debug.Print(" FeatureScopeBodiesCnt = " + swSweep.GetFeatureScopeBodiesCount());

            //swSelectType_e
            Debug.Print(" GetPathType = " + swSweep.GetPathType());

            Debug.Print(" Wall thickness foward = " + swSweep.GetWallThickness(true) * 1000.0 + " mm");
            Debug.Print(" Wall thickness reverse = " + swSweep.GetWallThickness(false) * 1000.0 + " mm");
            Debug.Print(" IsBossFeature = " + swSweep.IsBossFeature());
            Debug.Print(" IsThinFeature = " + swSweep.IsThinFeature());
            Debug.Print(" MaintainTangency = " + swSweep.MaintainTangency);
            Debug.Print(" Merge = " + swSweep.Merge);
            Debug.Print(" MergeSmoothFaces = " + swSweep.MergeSmoothFaces);
            Debug.Print(" PropagateFeatureToParts = " + swSweep.PropagateFeatureToParts);

            //swTangencyType_e
            Debug.Print(" StartTangencyType = " + swSweep.StartTangencyType);

            Debug.Print(" TangentPropagation = " + swSweep.TangentPropagation);
            Debug.Print(" ThinWallType = " + swSweep.ThinWallType);

            //swTwistControlType_e
            Debug.Print(" TwistControlType = " + swSweep.TwistControlType);

            //swCutSweepOption_e
            Debug.Print(" CutSweepOption = " + swSweep.GetCutSweepOption());

            // Roll forward

            swSweep.ReleaseSelectionAccess();
        }

        public SldWorks swApp;

    }
}