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Create Hole Wizard Feature Data Object and Hole Wizard Feature Example (VBA)

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This example shows how to create a hole wizard feature data object and a hole wizard feature.




' Preconditions: Model document is open.


' Postconditions: Hole wizard feature is created

'                 on the selected face of the model.



Option Explicit


Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swModelDocExt As SldWorks.ModelDocExtension

Dim swFeatMgr As SldWorks.FeatureManager

Dim swFeat As SldWorks.Feature

Dim swWzdHole As WizardHoleFeatureData2

Dim swFeatDataObj As Object

Dim boolstatus As Boolean


Sub main()


Set swApp = Application.SldWorks

Set swModel = swApp.ActiveDoc

Set swModelDocExt = swModel.Extension

Set swFeatMgr = swModel.FeatureManager


' Create the hole wizard feature data object

Set swFeatDataObj = swFeatMgr.CreateDefinition(swFmHoleWzd)


Set swWzdHole = swFeatDataObj

' Initialize the hole wizard feature

swWzdHole.InitializeHole swWzdCounterBore, swStandardISO, swStandardISOHexBolt, "M48", swEndCondBlind

'Change the hole wizard feature's depth

swWzdHole.HoleDepth = 0.15

'Change the hole wizard feature's diameter

swWzdHole.HoleDiameter = 0.0555


' Select the face on which to create the hole

boolstatus = swModelDocExt.SelectByID2("", "FACE", 0.09000000000003, -0.01278177510699, 0.04695929736232, False, 0, Nothing, 0)

' Create the hole wizard feature

Set swFeat = swFeatMgr.CreateFeature(swWzdHole)


End Sub


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