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Create Local Sketch-driven Pattern Example (VB.NET)

This example shows how to create a local sketch-driven pattern feature.

' Preconditions:
' 1. Specified assembly document to open exists.
' 2. Open the Immediate window.
' Postconditions:
' 1. Opens specified assembly document.
' 2. Creates a sketch for the local sketch-driven
'    pattern.
' 3. Selects an assembly component and the just-created
'    sketch for the local sketch-driven pattern.
' 4. Creates local sketch-driven pattern.
' 5. Gets the local sketch-driven pattern feature data.
' 6. Prints to the Immediate window values and settings
'    of the local sketch-driven pattern.
NOTE: Because this assembly is used elsewhere, do not save
' any changes when closing it.
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
Partial Class SolidWorksMacro
    Public Sub Main()
        Dim swModel As ModelDoc2
        Dim swSketchMgr As SketchManager
        Dim swSketchPoint As SketchPoint
        Dim swModelDocExt As ModelDocExtension
        Dim swFeatMgr As FeatureManager
        Dim swFeat As Feature
        Dim swLocalSketchPatternFeat As LocalSketchPatternFeatureData
        Dim fileName As String
        Dim status As Boolean
        Dim errors As Integer
        Dim warnings As Integer
        'Open assembly document
        fileName = "C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\samples\tutorial\api\assem1.sldasm"
        swModel = swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocASSEMBLY, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
        'Create sketch
        swSketchMgr = swModel.SketchManager
        swSketchPoint = swSketchMgr.CreatePoint(0.025, -0.05, 0.0#)
        swSketchPoint = swSketchMgr.CreatePoint(0.05, -0.075, 0.0#)
        swSketchPoint = swSketchMgr.CreatePoint(0.1, -0.05, 0.0#)
        'Select a component and the just-created sketch
        'for the local sketch-driven pattern
        swModelDocExt = swModel.Extension
        status = swModelDocExt.SelectByID2("TestPart1-1@assem1""COMPONENT", 0, 0, 0, False, 1, Nothing, 0)
        status = swModelDocExt.SelectByID2("Sketch1""SKETCH", 0, 0, 0, True, 16, Nothing, 0)
        'Insert local sketch-driven pattern
        swFeatMgr = swModel.FeatureManager
        swFeat = swFeatMgr.FeatureLocalSketchDrivenPattern(swLocalSketchPatternReferencePoint_e.swLocalSketchPatternComponentOrigin)
        'Get local sketch-driven pattern feature data
        swLocalSketchPatternFeat = swFeat.GetDefinition
        Debug.Print("Local sketch-driven pattern properties: ")
        Debug.Print("  Number of components: " & swLocalSketchPatternFeat.GetPatternComponentCount)
        Debug.Print("  Number of items skipped: " & swLocalSketchPatternFeat.GetSkippedItemCount)
        Debug.Print("  Type of reference point: " & swLocalSketchPatternFeat.ReferencePoint)
        Debug.Print("  Is reference point a closed curve, sketch point, vertex, or default value: " & swLocalSketchPatternFeat.GetReferencePointType)
    End Sub
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
End Class

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