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Create Radiate Surface Feature Example (VB.NET)

This example shows how to create a radiate surface feature.

'----------------------------------------------------------------------------
' Preconditions:
' 1. Verify that the specified document template exists.
' 2. Open an Immediate window.
'
' Postconditions:
' 1. Creates a new model document with a feature extrusion.

' 2. Creates Boss-Extrude1 and Surface-Radiate1 in the graphics area and
'    FeatureManager design tree.

' 3. Inspect the Immediate window.
'----------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
 
 
Partial Class SolidWorksMacro
 
 
    Dim Part As ModelDoc2
    Dim swSelMgr As SelectionMgr
    Dim swSelData As SelectData
    Dim swRadiate As SurfaceRadiateFeatureData
    Dim swFeat As Feature
    Dim swEnt As Edge
    Dim vRadEnt As Object
    Dim swRadDirEnt As Entity
    Dim i As Integer
    Dim boolStatus As Boolean
 
    Sub main()
 
        Part = swApp.NewDocument("C:\ProgramData\SolidWorks\SOLIDWORKS 2015\templates\Part.prtdot", 0, 0, 0)
        Part = swApp.ActiveDoc
 
        boolStatus = Part.Extension.SelectByID2("Front Plane""PLANE", -0.0448901407839529, 0.0279954694016864, 0.00466820674117181, False, 0, Nothing, 0)
        Part.SketchManager.InsertSketch(True)
        Part.ClearSelection2(True)
        boolStatus = Part.Extension.SetUserPreferenceToggle(swUserPreferenceToggle_e.swSketchAddConstToRectEntity, swUserPreferenceOption_e.swDetailingNoOptionSpecified, False)
        boolStatus = Part.Extension.SetUserPreferenceToggle(swUserPreferenceToggle_e.swSketchAddConstLineDiagonalType, swUserPreferenceOption_e.swDetailingNoOptionSpecified, True)
        Dim vSkLines As Object
        vSkLines = Part.SketchManager.CreateCornerRectangle(-0.0555749908365768, 0.0329075527136081, 0, 0.0478203409524033, -0.0317145296545045, 0)
        Part.ClearSelection2(True)
        Part.SketchManager.InsertSketch(True)
        Part.ShowNamedView2("*Trimetric", 8)
        Part.SketchManager.InsertSketch(True)
        Part.ClearSelection2(True)
        boolStatus = Part.Extension.SelectByID2("Sketch1""SKETCH", 0, 0, 0, False, 4, Nothing, 0)
 
        Dim myFeature As Object
        myFeature = Part.FeatureManager.FeatureExtrusion2(TrueFalseFalse, 0, 0, 0.00254, 0.00254, FalseFalseFalseFalse, 0.0174532925199433, 0.0174532925199433, FalseFalseFalseFalseTrueTrueTrue, 0, 0, False)
 
        boolStatus = Part.Extension.SelectByID2("""EDGE", -0.0447337592343047, 0.0328467250718631, 0.00258132540182032, False, 2, Nothing, 0)
        boolStatus = Part.Extension.SelectByID2("""EDGE", -0.0556265649287866, 0.0156695101210289, 0.0025672149453726, True, 2, Nothing, 0)
        boolStatus = Part.Extension.SelectByID2("""EDGE", -0.0140113588298618, -0.0317157034173761, 0.00254079743683633, True, 2, Nothing, 0)
        boolStatus = Part.Extension.SelectByID2("""EDGE", 0.047780958393389, -0.00542256709667299, 0.00256078163948814, True, 2, Nothing, 0)
        boolStatus = Part.Extension.SelectByID2("""FACE", 0.0478203409524554, -0.00305747564971171, 0.000546558985774936, True, 1, Nothing, 0)
 
        Part.InsertRadiateSurface(0.0254, FalseFalse)
 
        swSelMgr = Part.SelectionManager
        swSelData = swSelMgr.CreateSelectData
 
        boolStatus = Part.Extension.SelectByID2("Surface-Radiate1""REFSURFACE", 0, 0, 0, False, 0, Nothing, 0)
 
        swFeat = swSelMgr.GetSelectedObject6(1, -1)
        swRadiate = swFeat.GetDefinition
 
        ' Get radiate surface data
        Debug.Print("File = " & Part.GetPathName)
        Debug.Print("  " & swFeat.Name)
        Debug.Print("    Distance: " & swRadiate.Distance * 1000.0# & " mm")
        Debug.Print("    Flip? " & swRadiate.Flip)
        Debug.Print("    Propagate to tangent faces? " & swRadiate.PropagateToTangentFaces)
 
        ' Roll back to get direction reference and radiated edges
        boolStatus = swRadiate.AccessSelections(Part, Nothing)
        swRadDirEnt = swRadiate.DirectionReference
        Part.ClearSelection2(True)
 
        vRadEnt = swRadiate.RadiatedEntities
 
        Debug.Print("Type as defined in swSelectType_e:)
        For i = 0 To swRadiate.GetRadiatedEntitiesCount - 1
 
            swEnt = vRadEnt(i)
            Debug.Print("    Radiated Entity(" & i & ") = " & swEnt.GetType)
 
        Next i
 
        swRadiate.ReleaseSelectionAccess()
 
 
    End Sub
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class
 

 



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