Create Relative Drawing View Example (C#)
This example shows how to create a relative drawing view.
// ******************************************************************************
// Preconditions:
// 1. Open install_dir\samples\tutorial\api\maingrip.sldprt.
// 2. Select File > Make Drawing from Part.
// 3. Run the macro.
//
// Postconditions:
// 1. Iterates through the drawing views
// in the View Palette and drops
// *Current drawing view in the drawing.
// 2. Activates the part.
// 3. Selects two faces for the relative drawing view.
// 4. Activates the drawing.
// 5. Creates and inserts a relative drawing
// view using the selected faces.
//
// NOTE: Because the part document is used elsewhere, do not
// save any changes when closing it.
// ******************************************************************************
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
namespace CreateRelativeViewCSharp.csproj
{
partial class SolidWorksMacro
{
ModelDoc2 swModel;
DrawingDoc swDrawing;
View swView;
ModelDocExtension swModelDocExt;
string fileName;
bool status;
int errors;
int warnings;
int numViews;
object[] viewNames;
string viewName;
string viewPaletteName;
int i;
public void Main()
{
swDrawing = (DrawingDoc)swApp.ActiveDoc;
// Get number of views on View Palette
numViews = 0;
viewNames = (object[])swDrawing.GetDrawingPaletteViewNames();
// Iterate through views on View Palette
// When view name equals *Current, drop
// that view in drawing
if (!((viewNames == null)))
{
numViews = (viewNames.GetUpperBound(0) - viewNames.GetLowerBound(0));
for (i = 0; i <= numViews; i++)
{
viewPaletteName = (string)viewNames[i];
if ((viewPaletteName == "*Current"))
{
swView = (View)swDrawing.DropDrawingViewFromPalette2(viewPaletteName, 0.0, 0.0, 0.0);
}
}
}
// Activate the part document and
// select two faces for the relative drawing view
swApp.ActivateDoc3("maingrip.sldprt", false, (int)swRebuildOnActivation_e.swUserDecision, ref errors);
swModel = (ModelDoc2)swApp.ActiveDoc;
swModelDocExt = (ModelDocExtension)swModel.Extension;
swModel.ClearSelection2(true);
status = swModelDocExt.SelectByID2("", "FACE", 0.0466263268498324, 0.00558799999987514, -0.00617351393179888, false, 1, null, 0);
status = swModelDocExt.SelectByID2("", "FACE", 0.0504738910727269, 0.00167315253537481, -0.00496149996774875, true, 2, null, 0);
// Activate the drawing document
// Create and insert the relative drawing view using
// the selected faces
// Activate the relative drawing view
swApp.ActivateDoc3("maingrip - Sheet1", false, (int)swRebuildOnActivation_e.swUserDecision, ref errors);
swDrawing = (DrawingDoc)swApp.ActiveDoc;
fileName = "C:\\Program Files\\SOLIDWORKS Corp\\SOLIDWORKS\\samples\\tutorial\\api\\maingrip.sldprt";
swView = (View)swDrawing.CreateRelativeView(fileName, 0.203608914116486, 0.493530187561698, (int)swRelativeViewCreationDirection_e.swRelativeViewCreationDirection_FRONT, (int)swRelativeViewCreationDirection_e.swRelativeViewCreationDirection_RIGHT);
status = swDrawing.ActivateView("Drawing View2");
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}