Hide Table of Contents

Get Points of Repeating Elements in Table-driven Pattern (VB.NET)

This example shows that the points that describe the locations of the repeating elements in a table-driven pattern are based on the table-driven pattern's coordinate system.


'---------------------------------------------
' Preconditions:
' 1. Specified file exists.
' 2. Open the Immediate window.
'
' Postconditions: The coordinates of the
' points for the two repeating elements in the
' table-driven pattern appear in the Immediate
' window.
'
'---------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics

Partial Class SolidWorksMacro

    
Public Sub main()

        
Dim swModel As ModelDoc2
        
Dim swModelDocExt As ModelDocExtension
        
Dim swSelMgr As SelectionMgr
        
Dim swFeat As Feature
        
Dim swCoordinateData As CoordinateSystemFeatureData
        
Dim swTablePatternFeatData As TablePatternFeatureData
        
Dim swMathTransform As MathTransform
        
Dim swMathUtility As MathUtility
        
Dim swMathPoint As MathPoint
        
Dim status As Boolean
        Dim errors As Integer
        Dim warnings As Integer
        Dim filename As String
        Dim points As Object
        Dim point As String
        Dim pointsArray(2) As Double
        Dim i As Integer

        filename = "C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\samples\tutorial\api\tablepattern.sldprt"

        swModel = swApp.OpenDoc6(filename, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
        swModelDocExt = swModel.Extension
        swSelMgr = swModel.SelectionManager

        
' Select the table-driven pattern
        status = swModelDocExt.SelectByID2("TPattern1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        swFeat = swModel.SelectionManager.GetSelectedObject6(1, -1)


        swTablePatternFeatData = swFeat.GetDefinition
        swTablePatternFeatData.AccessSelections(swModel,
Nothing)

        
' Get the points of the repeating elements in the table-driven pattern
        ' and transform them to coordinates
        swCoordinateData = swTablePatternFeatData.CoordinateSystem.GetDefinition
        swCoordinateData.AccessSelections(swModel,
Nothing)
        swMathTransform = swCoordinateData.Transform
        swCoordinateData.ReleaseSelectionAccess()

        swMathUtility = swApp.GetMathUtility

        points = swTablePatternFeatData.PointArray

        Debug.Print("Number of points: " & swTablePatternFeatData.GetPointCount)

        
For i = 0 To UBound(points) Step 3
            pointsArray(0) = points(i) : pointsArray(1) = points(i + 1) : pointsArray(2) = points(i + 2)
            swMathPoint = swMathUtility.CreatePoint(pointsArray)

            swMathPoint = swMathPoint.MultiplyTransform(swMathTransform.Inverse)

            
' Print the coordinates for the two repeating elements in the table-driven pattern
            point = "x: " & swMathPoint.ArrayData(0) & " y: " & swMathPoint.ArrayData(1) & " z: " & swMathPoint.ArrayData(2)

            Debug.Print(point)

        
Next

        swTablePatternFeatData.ReleaseSelectionAccess()

    
End Sub

    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks


End Class



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Get Points of Repeating Elements in Table-driven Pattern (VB.NET)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2015 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.