Hide Table of Contents

Insert New Virtual Component Example (VBA)

This example shows how to insert a new part as a virtual component in an assembly and save it to an external file.

' Preconditions:

' 1. Open: <SOLIDWORKS_install_dir>\samples\tutorial\smartcomponents\stepped_shaft.sldasm
' 2. A planar face on the assembly is selected.
' 3. Step through this macro (F8).
' Postconditions:

' 1. The new part is inserted as a virtual component in the assembly.
' 2. The virtual component is saved to an external file,
'       and its name changes in the FeatureManager design tree.
' NOTE: Because this assembly is used in a SOLIDWORKS online tutorial, do not
'       save the assembly when you close it.

Option Explicit

Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swAssy As SldWorks.AssemblyDoc
Dim swComponent As SldWorks.Component2
Dim swSelMgr As SldWorks.SelectionMgr
Dim status As Long

Sub Main()

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc
    Set swAssy = swModel

    ' Get the pre-selected planar face
    Dim swFeature  As SldWorks.Face2
    Set swSelMgr = swModel.SelectionManager
    Set swFeature = swSelMgr.GetSelectedObject6(1, 0)

    ' Create the part and insert it as a virtual component
    ' in the assembly
    status = swAssy.InsertNewVirtualPart(swFeature, swComponent)

    If status = 1 Then

        Debug.Print "Name of virtual component: " & swComponent.Name2

        ' Check to see if the part is a virtual component
        Debug.Print "Is component virtual? " & swComponent.IsVirtual

        Dim objFSO As Object
        Dim objFile As Object
        Dim compName As String
        Dim splits As Variant

        Set objFSO = CreateObject("Scripting.FileSystemObject")
        Set objFile = objFSO.GetFile(swModel.GetPathName)

        splits = Split(swComponent.Name, "^")
        compName = objFSO.GetParentFolderName(objFile) & "\" & splits(0)

        If swComponent.GetModelDoc2.GetType = swDocPART Then
            compName = compName & ".sldprt"
            compName = compName & ".sldasm"
        End If

        Debug.Print "Name of saved virtual component: " & compName
        swComponent.SaveVirtualComponent compName

        Debug.Print "Error code returned when attempting to insert new part as virtual component: " & status
    End If

    swModel.ClearSelection2 (True)

End Sub

Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Insert New Virtual Component Example (VBA)
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: API Help (English only) 2015 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.