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Insert New Virtual Component Example (VB.NET)

This example shows how to insert a new part as a virtual component in an assembly and save it to an external file.

'---------------------------------------------------------------------
' Preconditions:
' 1. Open:

' <SOLIDWORKS_install_dir>\samples\tutorial\smartcomponents\stepped_shaft.sldasm
' 2. A planar face on the assembly is selected.
'
' Postconditions:
' 1. The new part is inserted as a virtual component in the assembly.
' 2. The virtual component is saved to an external file,
'    and its name changes in the FeatureManager design tree.
'
' NOTE: Because this assembly is used in a SOLIDWORKS online tutorial, do not
'       save the assembly when you close it.
'---------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics

Partial Class SolidWorksMacro

    
Dim swModel As ModelDoc2
    
Dim swAssy As AssemblyDoc
    
Dim swComponent As Component2
    
Dim swSelMgr As SelectionMgr
    
Dim objFSO As Object
    Dim objFile As Object
    Dim compName As String
    Dim splits As Object
    Dim status As Long

    Sub Main()

        swModel = swApp.ActiveDoc
        swAssy = swModel

        
' Get the pre-selected planar face
        Dim swFeature As Face2
        swSelMgr = swModel.SelectionManager
        swFeature = swSelMgr.GetSelectedObject6(1, 0)

        
' Create the part and insert it as a virtual component
        ' in the assembly
        status = swAssy.InsertNewVirtualPart(swFeature, swComponent)

        
If status = 1 Then

            Debug.Print("Name of virtual component: " & swComponent.Name2)

            
' Check to see if the part is a virtual component
            Debug.Print("Is component virtual? " & swComponent.IsVirtual)

            objFSO = CreateObject(
"Scripting.FileSystemObject")
            objFile = objFSO.GetFile(swModel.GetPathName)

            splits = Split(swComponent.Name,
"^")
            compName = objFSO.GetParentFolderName(objFile) &
"\" & splits(0)

            
Dim compModel As ModelDoc2
            compModel = swComponent.GetModelDoc

            
If compModel.GetType = swDocumentTypes_e.swDocPART Then
                compName = compName & ".sldprt"
            Else
                compName = compName & ".sldasm"
            End If

            Debug.Print("Name of saved virtual component: " & compName)
            swComponent.SaveVirtualComponent(compName)

        
Else
            Debug.Print("Error code returned when attempting to insert new part as virtual component: " & status)
        
End If

        swModel.ClearSelection2(True)

    
End Sub

    
    
Public swApp As SldWorks


End Class



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