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InsertSheetMetalLoftedBend2 Method (IFeatureManager)

Inserts a lofted bend in a sheet metal part.

.NET Syntax

Visual Basic (Declaration) 
Function InsertSheetMetalLoftedBend2( _
   ByVal ThickDirType As System.Integer, _
   ByVal Thickness As System.Double, _
   ByVal BFormed As System.Boolean, _
   ByVal DRadius As System.Double, _
   ByVal BReferToEndPoint As System.Boolean, _
   ByVal EFacetOption As System.Integer, _
   ByVal DChordTol As System.Double, _
   ByVal INumBends As System.Integer, _
   ByVal DSegLength As System.Double, _
   ByVal DSegAngle As System.Double _
) As Feature
Visual Basic (Usage) 
Dim instance As IFeatureManager
Dim ThickDirType As System.Integer
Dim Thickness As System.Double
Dim BFormed As System.Boolean
Dim DRadius As System.Double
Dim BReferToEndPoint As System.Boolean
Dim EFacetOption As System.Integer
Dim DChordTol As System.Double
Dim INumBends As System.Integer
Dim DSegLength As System.Double
Dim DSegAngle As System.Double
Dim value As Feature
 
value = instance.InsertSheetMetalLoftedBend2(ThickDirType, Thickness, BFormed, DRadius, BReferToEndPoint, EFacetOption, DChordTol, INumBends, DSegLength, DSegAngle)
C# 
Feature InsertSheetMetalLoftedBend2( 
   System.int ThickDirType,
   System.double Thickness,
   System.bool BFormed,
   System.double DRadius,
   System.bool BReferToEndPoint,
   System.int EFacetOption,
   System.double DChordTol,
   System.int INumBends,
   System.double DSegLength,
   System.double DSegAngle
)
C++/CLI 
Feature^ InsertSheetMetalLoftedBend2( 
&   System.int ThickDirType,
&   System.double Thickness,
&   System.bool BFormed,
&   System.double DRadius,
&   System.bool BReferToEndPoint,
&   System.int EFacetOption,
&   System.double DChordTol,
&   System.int INumBends,
&   System.double DSegLength,
&   System.double DSegAngle
) 

Parameters

ThickDirType

Toggles the thickening direction:

  • 0 = outside

  • 1 = inside (default value)

Thickness

Thickness of the bend

BFormed
True to insert a formed lofted bend; false to insert a bent lofted bend (default)
DRadius
Bend radius; valid only if BFormed is false
BReferToEndPoint

True to calculate facet transitions using theoretical vertexes, false to calculate facet transitions using the smallest possible arcs that avoid interference between bend areas; valid only if BFormed is false

EFacetOption

Faceting option as defined in swLoftedBendFacetOptions_e; valid only if BFormed is false

DChordTol
Chord tolerance or maximum distance between the arc and linear segment of a chord; valid only if EFacetOption is set to swLoftedBendFacetOptions_e.swChordTolerance and BFormed is false
INumBends
Maximum number of bends per transition segment; valid only if EFacetOption is set to swLoftedBendFacetOptions_e.swBendsPerTransitionSegment and BFormed is false
DSegLength
Maximum length of the linear segment; valid only if EFacetOption is set to swLoftedBendFacetOptions_e.swSegmentLength and BFormed is false
DSegAngle
Maximum angle between adjacent linear segments; valid only if EFacetOption is set to swLoftedBendFacetOptions_e.swSegmentAngle and BFormed is false

Return Value

IFeature

Example

Remarks

Before calling this method, you must select at least two sketch profiles that are on parallel planes. You can either multi-select them in the graphics area or call IModelDocExtension::SelectByID2 with Mark = 1 for each sketch profile you want to select.

 

See Also

Availability

SOLIDWORKS 2014 FCS, Revision Number 22.0


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